CATIA Training CATIA Aerospace Sheet Metal Design Detailed Steps COPYRIGHT DASSAULT SYSTEMES Version 5 Release 19 January 2009 EDU-CAT-EN-ASL-FS-V5R19
Table of Contents Additional Exercise: Aerostructure...3 Step 1: Setting Parameters...3 Step 2: Creating the Web...6 Step 3: Creating Surfacic Flanges...8 Step 4: Creating the Joggle...11 Step 5: Creating Cutouts and Holes...13 Step 6: Creating Flanged Holes...16 Step 7: Creating Beads...19 Step 8: Create an Expert Check...21 Step 9: Modifying and Flattening the Part...24 Additional Exercise: Bracket...26 Step 1: Setting Parameters...26 Step 2: Creating the Web...29 Step 3: Creating a Joggle on Web...31 Step 4: Creating Surfacic Flanges...32 Step 5: Creating the Joggle...35 Step 6: Creating Flanged Holes...36 Step 7: Creating the Circular Cutouts...38 Step 8: Creating Chamfers...40 Step 9: Flattening the Part...41 Additional Exercise: Fighter Web Structure...42 Step 1: Setting Parameters...42 Step 2: Creating the Web...45 Step 3: Creating Surfacic Flanges...46 Step 4: Creating the Joggle...50 Step 5: Creating Cutout on Flange and Corners...52 Step 6: Creating Cutouts and Circular Cutouts...54 Step 7: Creating the Bead...59 Step 8: Modifying and Flattening the Part...61 Additional Exercise: Rib...63 Step 1: Setting Parameters...63 Step 2: Creating the Web...65 Step 3: Creating Flanges...67 Step 4: Creating the Joggle...72 Step 5: Creating Cutouts and Circular Cutouts...74 Step 6: Creating a Circular Stamp...80 Step 7: Modifying and Flattening the Part...81 Additional Exercise: Fairing Linking...83 Step 1: Setting Parameters...83 Step 2: Creating the Web...85 Step 3: Creating the Flange...87 Step 4: Creating the Circular Cutout...88 Step 5: Creating a Flanged Hole...89 Step 6: Creating Beads...91 Step 8: Flattening the Part...94 COPYRIGHT DASSAULT SYSTEMES 2
Additional Exercise: Aerostructure Step 1: Setting Parameters In this step, we open the ASL part and set default sheet metal parameters. Open Aerospace Sheet Metal Design workbench Open Aerostructure.CAT part which is located in the ASL_F\Student\Data\Aerostructure Directory COPYRIGHT DASSAULT SYSTEMES 3
Select View \ Render Style \ Parallel Activate PartBody in the tree Select Aerospace Sheet Metal Design Parameters icon In the Parameters tab, click Sheet Standard Files button Select AluminumTable.xls file in the ASL_F\Student\Data\Parameter_Tables Directory Select design table icon for the Bend Radius parameter COPYRIGHT DASSAULT SYSTEMES 4
Select the second row (2mm) in the Bend Radius Table Set Compensation options as shown on illustration, including the selection of the Design Table FormulaRunout.xls located in ASL_F\Student\Data\Parameter_Tables Directory Click OK COPYRIGHT DASSAULT SYSTEMES 5
Step 2: Creating the Web In this step, we create the web of the Sheet Metal Part. Select the Web icon Select xy plane as Support Geometry Select the following boundary elements: yellow surface green curve green surface green plane red curve Select OK COPYRIGHT DASSAULT SYSTEMES 6
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Step 3: Creating Surfacic Flanges In this step, we create a planar flange and a curved flange 1.1 - Planar flange Select the surfacic flange icon Base Feature: select the web Check Exact is setting for Support Type Support Geometry: select the green plane Check Flange Material Direction and Flange Base Feature Direction are pointing inside the web (click on red arrows to invert them). Select EOP tab Enter 30mm for Length From OML value COPYRIGHT DASSAULT SYSTEMES 8
Select Sides and Corner tab Enter 5mm for Corner 1 and Corner 2 radii Click OK 1.2 - Curved flange Select surfacic flange icon Base Feature: select the web Check Exact is setting for Support Type Support Geometry: select yellow surface Check Flange Material Direction and Flange Base Feature Direction are pointing the green surface (click on red arrows to invert them). Select EOP tab Enter 35mm for Length From OML value COPYRIGHT DASSAULT SYSTEMES 9
Select Sides and Corner tab Enter 10mm for Corner 1 and Corner 2 radii Click OK COPYRIGHT DASSAULT SYSTEMES 10
Step 4: Creating the Joggle In this step, we create a joggle on the curved flange. Select Joggle icon Support: select the curved flange Joggle plane: select the blue plane Click on the Depth direction arrow to invert it Set parameters as shown on illustration Click OK COPYRIGHT DASSAULT SYSTEMES 11
Unfold the part Modify Surfacic Flange 2 so as to activate Joggle compensation COPYRIGHT DASSAULT SYSTEMES 12
Step 5: Creating Cutouts and Holes In this step we create cut outs on the web using 3 sketches and holes using 4 points 1.3 - Cutouts Select Cut Out icon Click on the pink curve Check orange arrow is pointing inside the curve Click OK COPYRIGHT DASSAULT SYSTEMES 13
Repeat these operations using the following profiles: 1.4 - Circular Cutouts Select Circular Cutouts icon Select one of the four white cross points Select web as support Choose Index hole type Select Standard Files command Select Design table icon Choose 10mm diameter (6 th row) Select three remaining white cross points in a sequence Select OK COPYRIGHT DASSAULT SYSTEMES 14
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Step 6: Creating Flanged Holes In this step, we create two flanged holes on the web Select Flanged Hole icon Select one of the two green points located on the web (the one closer to the planar Surfacic Flange) Select the web Check orange arrow is pointing the flanges direction (click on arrow to invert it) Select Standards Files button COPYRIGHT DASSAULT SYSTEMES 16
Select design table icon for the Diameter parameter. Select the 3 rd row (50mm) in the table Select OK twice The second Flanged hole will be obtained by applying a Rectangular Pattern Select Rectangular Pattern icon Select 1 st flanged hole to be patterned Set Instance parameter value to 2 Right select the Reference Element filed and choose Create Line Select both green cross points and OK Right Select the Spacing field and choose Measure Item command Select previously created Line COPYRIGHT DASSAULT SYSTEMES 17
Close Measuring Window by selecting OK Select Ok in Pattern Definition window to close the dialog. COPYRIGHT DASSAULT SYSTEMES 18
Step 7: Creating Beads In this step, we create three beads on the web Select Bead icon Select one of the three blue lines Check orange arrow is pointing the flanges direction Select Standards Files button Select design table icon Select the 4 th row in the table COPYRIGHT DASSAULT SYSTEMES 19
Select OK twice Repeat these operations using the two others blue lines COPYRIGHT DASSAULT SYSTEMES 20
Step 8: Create an Expert Check In this step, we verify that the clearance distance between the flanged hole and the surface Flange is respected, the calculation being based on the OML Go into Knowledge Expert Workbench Activate the Expert Check function Select if need be the Rulebase in your tree and click OK In the Check Editor COPYRIGHT DASSAULT SYSTEMES 21
Select in the tree the Surfacic Flange 1 and the Flanged Hole 1 which will appear in the 1 st Text Box respectively as Flange Surf and CATSm_ExtrudedHolePunch, we just have to nickname each one of this feature and separate them with a ; like this The next step consists into creating the rule into the 2 nd text box. In our case, we want that the distance between the 2 features OML to be superior to a fixed value, 30 mm, which translates in our case as : COPYRIGHT DASSAULT SYSTEMES 22
This is not the case, we have to correct this by modifying the position of the flanged hole For this, double-click on sketch.5 and move with the mouse its point two squares to the left as on the picture Then exit the sketcher and update if necessary The check is still red, let s update it manually. For this, right-click on RuleBase and use Manual Complete Solve The check becomes green => the clearance distance is respected COPYRIGHT DASSAULT SYSTEMES 23
Step 9: Modifying and Flattening the Part In this step, we modify the joggle runout, enlarge the green circle and we unfold the part Edit the joggle created on Surfacic Flange 2 Change the Runout Formula to Formula 2 Update if necessary COPYRIGHT DASSAULT SYSTEMES 24
Edit the sketch linked to the green circle (by double-clicking in the tree) which we have used to make the cut out Change the diameter constraint value from 30mm to 20mm Exit the sketcher Update if necessary Select the Unfold icon to flatten the part COPYRIGHT DASSAULT SYSTEMES 25
Additional Exercise: Bracket Step 1: Setting Parameters In this step, we open the ASL product and set default sheet metal parameters. Open Aerospace Sheet Metal Design workbench Open Bracket.CATProduct which is located in the ASL_F\Student\Data\Bracket Directory Select View \ Render Style \ Parallel Activate Bracket part in the tree Select Aerospace Sheet Metal Design Parameters icon COPYRIGHT DASSAULT SYSTEMES 26
In the Parameters tab, click Sheet Standard Files button Select AluminumTable.xls file in the Student\Data\Parameter_Tables directory Select OK Select design table icon for the Default Bend Radius parameter Select the second row (2mm) in the Bend Radius Table Select OK COPYRIGHT DASSAULT SYSTEMES 27
Set Compensation options as shown illustration Select OK COPYRIGHT DASSAULT SYSTEMES 28
Step 2: Creating the Web In this step, we create the web of the Sheet Metal part Select the Web icon Select XY plane Web_Support sketch (blue contour) COPYRIGHT DASSAULT SYSTEMES 29
Select OK COPYRIGHT DASSAULT SYSTEMES 30
Step 3: Creating a Joggle on Web In this step we define a 5mm joggle on the Web Select joggle icon Select Web as support Select green plane as joggle plane Select the role of the plane as start Select arrows so that they behave as shown on illustration Key in values in dedicated fields as shown on illustration Select OK Update if necessary COPYRIGHT DASSAULT SYSTEMES 31
Step 4: Creating Surfacic Flanges In this step, we create two planar surfacic flanges using Length From OML and Element FD for EOP types. 1.1 - First Flange Select Surfacic Flange icon Base Feature: select the web Select Support tab Select Angle Type Support curve: select PlanarFlange_Support sketch (yellow line) Check Angle value is set to 90deg Check the material and Base Feature Directions arrows are pointing inside the web Select EOP tab COPYRIGHT DASSAULT SYSTEMES 32
Select Element FD type Select Pink Plane Select Sides and Corners tab Select Standard for Side 1 and Side 2 Select None for Corners 1 and 2 Select OK 1.2 - Second Flange Select Surfacic Flange icon Base Feature: select the web Select Support tab COPYRIGHT DASSAULT SYSTEMES 33
Select Exact Type Support Geometry: select Reference YZ plane Check Flange Material Direction and Flange Base Feature Direction arrows are pointing the first flange Select EOP tab Select Element FD Boundary Element: select EOP_Support sketch (red curve) Select Sides and Corners tab Side 1: Standard Side 2: Standard Select None for Corners 1 and 2 radius Select OK. COPYRIGHT DASSAULT SYSTEMES 34
Step 5: Creating the Joggle In this step, we create a joggle on the second flange Select Joggle icon Support: select the second flange Joggle Plane: select Joggle Plane (red plane) Set joggle parameters values as shown on illustration Select OK COPYRIGHT DASSAULT SYSTEMES 35
Step 6: Creating Flanged Holes In this step, we create two flanged holes on the web. Select Flanged Hole icon Select one of the orange points Select the web Check orange arrow is pointing in the flange direction (Select to invert) Click on Standard Files Select design table icon Select 3 rd row Select OK twice COPYRIGHT DASSAULT SYSTEMES 36
Second Flanged Holes will be obtained by applying the same method on second orange point location COPYRIGHT DASSAULT SYSTEMES 37
Step 7: Creating the Circular Cutouts In this step, we create fastener holes on the second flange 1.3 - Eight first points Select Circular Cutout icon Select one of the white cross points (the most left for instance) Select the supporting flange Select the Fastener hole type Select Standard Files command Select Design Table icon COPYRIGHT DASSAULT SYSTEMES 38
Select 3 rd row (diameter 4mm) Select all other white cross points except the last most right one Select OK 1.4-9 th Fastener hole Repeat previous steps for the last most right hole definition. When selecting the Support, it is necessary to pick the right portion of the flange COPYRIGHT DASSAULT SYSTEMES 39
Step 8: Creating Chamfers Select Chamfer icon Set up Chamfer option and value in panel Length 8mm Angle 45deg Tangency Propagation Select Select all command Select OK COPYRIGHT DASSAULT SYSTEMES 40
Step 9: Flattening the Part In this part, we flatten the part in a second window Select Multi Viewer icon to display Unfolded part window Select View \ Render Style \ Parallel Reframe and rotate the view so that you have the Unfolded representation full size COPYRIGHT DASSAULT SYSTEMES 41
Additional Exercise: Fighter Web Structure Step 1: Setting Parameters In this step, we open the ASL part and set default sheet metal parameters. 1.1 - Open Aerospace Sheet Metal Design workbench 1.2 - Open Fighter_Web_Structure_Initial.CAT part which is located in the ASL_F\Student\Data\Fighter Web Structure directory 1.3 - Select View \ Render Style \ Parallel Define In Work Object PartBody in the tree COPYRIGHT DASSAULT SYSTEMES 42
Select Aerospace Sheet Metal Design Parameters icon Select Sheet Standard Files command 1.4 - Select AluminumTable.xls file located in ASL_F\Student\Data\Parameter_Tables directory Select Design table icon regarding Default Bend Radius Select 3 rd row (2.5mm) Select OK COPYRIGHT DASSAULT SYSTEMES 43
Set Compensation options as shown on illustration Select OK COPYRIGHT DASSAULT SYSTEMES 44
Step 2: Creating the Web In this step, we create the web of the Sheet Metal part Select the Web icon Boundaries: select the yellow contour Select OK COPYRIGHT DASSAULT SYSTEMES 45
Step 3: Creating Surfacic Flanges In this step, we create two surfacic flanges (one curved and one planar) 1.5 - Curved Surfacic Flange Select Flange icon Base Feature: select the web Support tab: Select Exact support type Support Geometry: select yellow surface Check Material and Base Feature directions arrows are pointing inside the web EOP tab: Select Length From OML type COPYRIGHT DASSAULT SYSTEMES 46
Enter 20mm for length value Select Sides and Corners tab Select Standard for Side 1 and Side 2 Enter 5mm for Corners 1 and 2 radius Select OK 1.6 - Planar surfacic flange Select Surfacic Flange icon Base Feature: select the web Support tab: Select Exact support type COPYRIGHT DASSAULT SYSTEMES 47
Support Geometry: select the red plane Check Flange Material Direction and Flange Base Feature Direction arrows are pointing inside the web (click arrows to invert them) Check Flange Direction arrow is pointing downward EOP tab: Select Element FD type Boundary Element: select the green curve Select Sides and Corners tab Select Standard for Side 1 and Side 2 Enter 5mm for Corners 1 and 2 radius Compensation tab: Check Joggle Apply command COPYRIGHT DASSAULT SYSTEMES 48
Select OK COPYRIGHT DASSAULT SYSTEMES 49
Step 4: Creating the Joggle In this step, we create a joggle on the planar flange Select Joggle icon Support: select the planar flange Joggle Plane: select the green plane Set Joggle parameters value as shown on illustration COPYRIGHT DASSAULT SYSTEMES 50
Select both Runout and Depth Direction so that they behave as shown on illustration Select OK Update if necessary Hide Extrude.1 afterwards COPYRIGHT DASSAULT SYSTEMES 51
Step 5: Creating Cutout on Flange and Corners In this step we create cut out on curved Flange and corners on sharp edges consequence of cutout. 1.7 - Flange Cutout Select CutOut icon Profile: select the blue contour Select OK COPYRIGHT DASSAULT SYSTEMES 52
1.8 - Corners Select Corner icon Key in Radius value : 5mm Select both edges to be filleted Select OK COPYRIGHT DASSAULT SYSTEMES 53
Step 6: Creating Cutouts and Circular Cutouts 1.9 - Fastener holes on Planar Flange Select Circular Cutout icon Select one of the white cross point on planar flange Select planar flange as support Choose Fastener as hole type Select Standard Files command Select Design Table icon regarding Diameter parameter Select 2 nd row (3mm) Select other white cross points to be assigned a fastener hole COPYRIGHT DASSAULT SYSTEMES 54
1.10 - Web Cutouts Select Cutout icon Select red Contour located on the web Check orange arrow is pointing inside the contour Select OK 1.11 - Manufacturing Circular Cutouts on Web Select Circular Cutout icon COPYRIGHT DASSAULT SYSTEMES 55
Select one of both pink cross points on web Select web as support Choose Manufacturing hole type Select Standard Files command Select Design Table icon regarding diameter parameter Select 5 th row (8mm) Select second pink cross point Select OK 1.12 - Slot cutout on web Select Cutout icon COPYRIGHT DASSAULT SYSTEMES 56
Select catalog icon regarding the profile selection field Double click Cutout chapter Double click UserFeatures family Double click on Slot_Contour Select XY Plane as Ref_Plane Select green point as Ref_Point Select green line as Ref_Axis COPYRIGHT DASSAULT SYSTEMES 57
Select Parameters Select Design Table icon regarding Slot Parameter field Select 8 th row out of Slot_Parameter_Table Select Close (Parameters window) Select OK (Insert Object window) Set arrow inside slot contour Select OK COPYRIGHT DASSAULT SYSTEMES 58
Step 7: Creating the Bead In this step, we create a bead on the web Select bead icon (Under flanged hole toggle key) Select the blue line located on the web Select Standard Files command Select Design Table icon facing Height parameter for instance Select 4th row out of Stamp Parameter Table COPYRIGHT DASSAULT SYSTEMES 59
Check orange arrow is pointing upward Select OK twice COPYRIGHT DASSAULT SYSTEMES 60
Step 8: Modifying and Flattening the Part In this step, we replace the curved flange support and finally we unfold the part Edit the curved flange definition window (by double-clicking the flange on the part on in the tree) Select Support tab Select in the Support Geometry field Select the blue surface COPYRIGHT DASSAULT SYSTEMES 61
Click OK Update if necessary Select Unfold icon to flatten the part COPYRIGHT DASSAULT SYSTEMES 62
Additional Exercise: Rib Step 1: Setting Parameters In this step, we open the ASL product and set default sheet metal parameters. Open Rib.CATProduct which is located in the ASL_F\Student\Data\Rib Directory Make Rib.CATPart active and ASL workbench active Select View \ Render Style \ Parallel Define In Work Object PartBody of Rib part in the tree Select Aerospace Sheet Metal Design Parameters icon Select Sheet Standard Files command Select AluminumTable.xls File located in ASL_F\Student\Data\Parameter_Tables COPYRIGHT DASSAULT SYSTEMES 63
Select Design Table icon regarding Default Bend Radius parameter Select 2 nd row (2mm) Select OK Compensation tab: Set options as shown on illustration COPYRIGHT DASSAULT SYSTEMES 64
Step 2: Creating the Web In this step, we create the rib web Select Web icon Select blue plane (Support geometry) COPYRIGHT DASSAULT SYSTEMES 65
Select 6 boundary elements 1 is the yellow surface 2 is the blue curve 3 is the red plane 4 is the purple curve 5 is the green plane 6 is the green curve Select OK COPYRIGHT DASSAULT SYSTEMES 66
Step 3: Creating Flanges In this step, we create three surfacic flanges 1.1-1 st flange definition Select Surfacic Flange icon Base feature: select the Web Select Support Tab Set Exact Support type Support Geometry: select green plane Check Flange Material Direction and Flange Base Feature Direction arrows are pointing inside the web Select EOP tab Select Length From OML type Enter 30mm for length value Select Sides and Corners tab Select Standard for Side 1 and Side 2 Enter 3mm for Corners 1 and 2 radius COPYRIGHT DASSAULT SYSTEMES 67
Select OK 1.2-2nd flange definition (surfacic curved flange) Select surfacic flange icon Base Feature: select the web Select Support tab Select Exact support type Support Geometry: select the yellow surface Check Flange Material Direction and Flange Base Feature Direction arrows are pointing inside the web (click arrows to invert them) Check Flange Direction arrow is pointing first flange direction Select EOP tab COPYRIGHT DASSAULT SYSTEMES 68
Select Length From OML type Length: enter 20mm Select Sides and Corners tab Select Standard for Side 1 and Side 2 Enter 3mm for Corners 1 and 2 radius Select OK 1.3-3 rd flange (surfacic planar one) Select surfacic flange icon Base feature: select the Web Select Support Tab COPYRIGHT DASSAULT SYSTEMES 69
Set Exact Support type Support Geometry: select red plane Check Flange Material Direction and Flange Base Feature Direction arrows are pointing inside the web Select EOP tab Select Length From OML type Enter 30mm for length value Select Sides and Corners tab COPYRIGHT DASSAULT SYSTEMES 70
Select Standard for Side 1 and Side 2 Enter 3mm for Corners 1 and 2 radius Compensation tab: Check Joggle Apply compensation Select OK COPYRIGHT DASSAULT SYSTEMES 71
Step 4: Creating the Joggle In this step, we create a joggle on the 3 rd flange Select Joggle icon Support: select the 3 rd flange Joggle Plane: select the yellow plane Set Joggle parameters values as shown on illustration COPYRIGHT DASSAULT SYSTEMES 72
Check Runout direction is pointing the purple curve Check Depth Direction is pointing the curved flange Key in values in dedicated fields as shown on illustration Select OK Update COPYRIGHT DASSAULT SYSTEMES 73
Step 5: Creating Cutouts and Circular Cutouts In this step, we create 2 cut outs and one Circular Cutout on the web. Both cutouts profiles will be imported from a catalog. 1.4 - Electrical cutout Select Cutout icon Select catalog icon regarding the profile selection field Double click Compound_Cutout chapter Double click Electrical_Cutout family Double click on Compound_Cutout powercopy COPYRIGHT DASSAULT SYSTEMES 74
Ref_Plane: select the blue plane Ref_Point: select the blue cross point Ref_Line: select red line Select Parameters button and enter 45deg for Setting_Angle value Select Close (Parameters window) COPYRIGHT DASSAULT SYSTEMES 75
Select OK twice 1.5 - Slot Cutout on Web Select CutOut icon Select catalog icon regarding the profile selection field Double click Cutout chapter Double click UserFeatures family Double click on Slot_Contour Select XY Plane as Ref_Plane Select green point as Ref_Point Select green line as Ref_Axis COPYRIGHT DASSAULT SYSTEMES 76
Select Parameters Select Design Table icon regarding Slot Parameter field Select 8 th row out of Slot_Parameter_Table and OK Select Close (Parameters window) Select OK (Insert Object window) heck arrow is correctly oriented inside slot contour Select OK COPYRIGHT DASSAULT SYSTEMES 77
1.6 - Manufacturing Circular Cutout Select Circular Cutout icon Select red point on web Select web as support Choose Manufacturing hole type Select Standard Files command Select Design Table icon regarding diameter parameter Select 6 th row (10mm) COPYRIGHT DASSAULT SYSTEMES 78
Select OK COPYRIGHT DASSAULT SYSTEMES 79
Step 6: Creating a Circular Stamp In this step, we create a circular stamp on the web Select Circular stamp icon Select the yellow point located on the web Select web geometry Select arrow so that it points upwards Select Standard Files command. Select OK COPYRIGHT DASSAULT SYSTEMES 80
Step 7: Modifying and Flattening the Part In this step, we modify a side of a planar flange and we unfold the part Edit the definition window of the 3 rd flange (by double-clicking on the part or in the tree) Select the Sides and Corners tab Change Side 2 type to Element FD Activate the Side Element field and select the yellow curve COPYRIGHT DASSAULT SYSTEMES 81
Select OK Update Select Unfold icon COPYRIGHT DASSAULT SYSTEMES 82
Additional Exercise: Fairing Linking Step 1: Setting Parameters In this step, we open the ASL product and set default sheet metal parameters. Open Fairing_Linking.CATPart which is located in the ASL_F\Student\Data\Fairing Linking Directory Make ASL workbench active Select View \ Render Style \ Parallel Define In Work Object PartBody of Fairing Linking part in the tree Select Aerospace Sheet Metal Design Parameters icon Select Sheet Standard Files command COPYRIGHT DASSAULT SYSTEMES 83
Select AluminumTable.xls File located in ASL_F\Student\Data\Parameter_Tables Select Design Table icon regarding Default Bend Radius parameter Select 2 nd row (2mm) Select OK Compensation tab: Set options as shown on illustration COPYRIGHT DASSAULT SYSTEMES 84
Step 2: Creating the Web In this step, we create the rib web Select Web icon Select Fuselage Complet (Support geometry) COPYRIGHT DASSAULT SYSTEMES 85
Select Split.4 as reference wire and Intersect.5 as point Select the 4 boundary elements 1 is the Split.4 2 is the Split.8 3 is the Split.6 4 is the Split.9 Select OK COPYRIGHT DASSAULT SYSTEMES 86
Step 3: Creating the Flange In this step, we create one surfacic flange 1.1-1 st flange definition Select Surfacic Flange icon Base feature: select the Web Select Support Tab Set Exact Support type Support Geometry: select yellow ribbon (Split.10) Check Flange Material Direction and Flange Base Feature Direction arrows are pointing inside the web Select EOP tab Select Element FD type Choose Project.4 as boundary element Select Sides and Corners tab Select Standard for Side 1 and Side 2 Enter 10 mm for Corners 1 and 2 radius Select OK COPYRIGHT DASSAULT SYSTEMES 87
Step 4: Creating the Circular Cutout Select Circular Cutout icon Select both extreme points on web Select web as support Choose Clearance Circular Cutout type Select Standard Files command Select Design Table icon regarding diameter parameter Select 6 th row (10mm) Select OK COPYRIGHT DASSAULT SYSTEMES 88
Step 5: Creating a Flanged Hole In this step, we create an extruded hole on the web Select Flanged hole icon Select middle point Select Web geometry Select arrow so that it points towards flanges orientation COPYRIGHT DASSAULT SYSTEMES 89
Select Standard Files command Select the third row from design table. Select OK COPYRIGHT DASSAULT SYSTEMES 90
Step 6: Creating Beads In this step, we create beads on the web Select Bead icon (under flanged hole toggle key) Select one of both white lines Select Standard Files command Select Design Table icon facing Height parameter for instance COPYRIGHT DASSAULT SYSTEMES 91
Select the 9th row out of Stamp Parameter Table Select OK Proceed the same way with the second line COPYRIGHT DASSAULT SYSTEMES 92
Step 7: Creating the Corners In this step, we create corners on the last 2 edges Activate the corner function Then select consecutively the 2 edges to be cornered Choose a radius of 10 mm Select OK COPYRIGHT DASSAULT SYSTEMES 93
Step 8: Flattening the Part In this part, we flatten the part in a second window Select Multi Viewer icon to display Unfolded part window Select View \ Render Style \ Parallel Reframe and rotate the view so that you have the Unfolded representation full size COPYRIGHT DASSAULT SYSTEMES 94