Simulation of Free Surface Viscoelastic Fluid Flow Using the viscoelasticinterfoam Solver
|
|
- Paul Reed
- 5 years ago
- Views:
Transcription
1 20 th European Symposium on Computer Aided Process Engineering ESCAPE20 S. Pierucci and G. Buzzi Ferraris (Editors) 2010 Elsevier B.V. All rights reserved. Simulation of Free Surface Viscoelastic Fluid Flow Using the viscoelasticinterfoam Solver Jovani L. Favero, a Nilo S. M. Cardozo, a Argimiro R. Secchi, b Hrvoje Jasak c a Chemical Engineering Depart. EE/UFRGS - Universidade Federal do Rio Grande do Sul, R. Eng. Luiz Englert, s/n Centro Porto Alegre, RS Brazil, favero@enq.ufrgs.br, nilo@enq.ufrgs.br b Chemical Engineering Program PEQ/COPPE Universidade Federal do Rio de Janeiro, Av. Horácio Macedo, 2030 CT - G116 Ilha do Fundão Rio de Janeiro, RJ Brazil, arge@peq.coppe.ufrj.br c FSB/Wikki Faculty of Mechanical Engineering and Naval Architecture, University of Zagreb, Croatia, and Wikki Ltd., London W8 7PU, United Kingdom, h.jasak@wikki.co.uk Abstract The understanding of polymeric fluids flows is of essential importance for several industry sectors, including plastic and food processing industries. The rheological response of viscoelastic fluids is quite complex, including combination of viscous and elastic effects and highly non-linear viscous and elastic phenomena. In a previous work we presented a solver for internal viscoelastic fluid flows, called viscoelasticfluidfoam, which was developed with the OpenFOAM computational fluid dynamics package and validated with experimental and numerical data from the literature for the analysis of a planar 4:1 contraction flow. In the present work will be tested the extension of the viscoelasticfluidfoam solver to the viscoelasticinterfoam solver used for analysis of free surface viscoelastic fluid flows using the VOF methodology. A classical die swell flow phenomena used in the rheology literature to present the concept of viscoelastic effects was simulated. The results obtained using Giesekus model showed the great potential of the developed formulation, once all phenomena observed experimentally were reproduced in the simulations. Keywords: Viscoelastic Fluids, VOF, OpenFOAM, Die Swell, CFD. 1. Introduction The understanding of viscoelastic fluid flow characteristics is of great interest for polymer and food processing industries. Unlike the Newtonian flow that is well understood, the flow of viscoelastic fluids is still a subject of great discussion. Most of the works on viscoelastic fluids found in literature treats internal flows using the geometry known as abrupt planar contraction. This is due mainly because this geometry was adopted as standard for viscoelastic fluids flow studies in 1987 during the fifth international workshop on numeric methods for non-newtonians fluids (Hassager, 1988). On the other hand, simulations using free surface viscoelastic flow are receiving a special attention mainly in the last two decades (Tomé et al., 2008). Flows considering free surface is particularly useful for industry that works with polymeric fluids, once processes as extrusion and injection molding of plastics, metallic leagues or fluids used in food industry depend always more on the knowledge of parameters that guarantee a high quality for their products (Khismatullin et al., 2006).
2 Favero et al. Regarding the modeling, the study of free surface flow presents the same bases of internal flows plus an appropriate methodology for treatment of free surface motion, such as the MAC (Marker-and-Cell) (Harlow and Welch, 1965) and VOF (Volume-of- Fluid) (Hirt and Nicols, 1981). An overview of literature works about viscoelastic free surface simulation can be found in Harvie et al. (2008). There are in the literature several works treating viscoelastic fluid flow with free surface, and the most of them use finite element method to solve simplified cases. In this work we overcome that limitation by showing results of a generic and flexible tool developed for treatment of free surface viscoelastic fluid flow using finite volume method and VOF methodology. This tool can be used to simulate complex geometries encountered in real problems of polymer and food processing industries, using non-structured and moving meshes, and allowing to choose among several different interpolation schemes, solvers for linear algebra, possibility of data processing parallelization and several constitutive equations for treatment of viscoelasticity. This work is an extension of our previous development of a solver, called viscoelasticfluidfoam (Favero et al., 2009), for treatment of internal viscoelastic flow using the OpenFOAM software (Weller et al., 1998). Such extension consists of increasing the capability of the viscoelasticfluidfoam solver, already available to the user in OpenFOAM, for the treatment of free surfaces flow using the VOF methodology, creating a new solver called viscoelasticinterfoam. The discretization of the flow governing equations in OpenFOAM is based on the finite volume method formulated with collocated variable arrangement, with pressure and velocity solved by segregated methods. The software offers a wide range of interpolation schemes, solvers and preconditioners for the discretized algebraic equation system. The results, studying a classic experiment in viscoelastic fluids flow with free surface: the die swell in the exit of a channel, show the success of the applied methodology. The rod-climbing experiment was also reproduced in the simulations but is not shown here due to lack of space. 2. Methodology In this section, the mathematical formulation, the strategy used to solve free surface viscoelastic fluid flow, and a description of the test problems are presented Mathematical Formulation The governing equations of laminar, incompressible, and isothermal flow of viscoelastic fluids are the mass conservation (continuity equation): u 0 and momentum conservation: u t uu p τ τ g (2) S P together with a mechanical constitutive equation that describes the relation between the stress and the deformation rate for a given fluid. In the above equations ρ is the density, u the velocity vector, p the pressure, τ S the solvent Newtonian contribution, and τ P the polymeric contribution. The solvent contribution is given by: τ S 2 D (3) S (1)
3 Simulation of Free Surface Viscoelastic Fluid Flow Using the Software OpenFOAM where η S is the solvent viscosity and D is the deformation rate tensor, given by: 1 T D uu (4) 2 The extra elastic contribution, corresponding to the polymeric part, is obtained from the solution of an appropriate constitutive differential equation. Various constitutive equations are found in literature, as for example, Maxwell, Oldroyd-B, Phan-Thien- Tanner (PTT), Finitely Extensible Nonlinear Elastic and so on. A well known and widely used is the Giesekus constitutive model described as (Giesekus, 1982): τp τ ( τ ) 2 P P τp pd p where λ and η P are the relaxation time and the polymer viscosity at zero shear rate, respectively, α is the dimensionless mobility factor, and τ P is the upper convected derivative of the elastic stress tensor defined as (Bird et al., 1987): τ T ( ) P P P P P t τ u τ u τ τ u (6) Another important subject is the treatment of the free surface. In the developed solver it was used the VOF methodology (Hirt and Nicols, 1981). In this method, the volume of fluid in a cell is computed as F vol = γv cell where V cell is the computational cell volume and γ is the liquid fraction in this cell. The value of γ in a cell varies between 0 and 1. A cell totally filled with one fluid presents γ = 1 and another totally filled with one different fluid have γ = 0. In the interface the value of γ is an intermediate value between 0 and 1, satisfying the following equation: u (1 ) ur 0 (7) t where u r is the velocity field subject to interface compression (Ubbink and Issa, 1999; Rusche, 2003). The last artificial term is only activated in the region of the interface due to the properties of the term γ(1-γ). The VOF methodology allows to solve the flow of two different fluids (two-phase flow) solving as for one fluid only, in other words, the same equations are solved for both fluids, the only difference is regarding to the physical properties. To make this possible, the physical properties in any control volume of the domain are given by the corresponding fraction of the fluid in that volume. It is mathematically obtained, considering a generic property θ, as: (1 ) (8) fluid1 fluid Test Geometry To test the implemented methodology, the reproduction of a classic example used to demonstrate viscoelasticity effects are carried out. The test consists in reproducing the die swell phenomena. Figure 1 shows the effect of die swell due to the fluid elasticity (Bird et al., 1987). An effect due to viscoelasticity is the presence of normal stress differences in shear flow. In addition to shear stress, viscoelastic fluids present an extra stress due to stretching and (5)
4 Favero et al. alignment of polymeric chains. In this experiment, it is considered a fluid flowing out of a capillary with diameter d. For Newtonian fluids the swell can vary 13% above or below of the diameter d, whereas for polymeric fluids, an increase in more than 300% relative to d can be found, depending on the fluid elasticity. To simulate this experiment a shear rate of 60 s -1 was used in the flowing channel. (a) (b) Figure 1: (a) Representation of the die swell effect for a Newtonian fluid (left) and a polymeric fluid (right) (Source: Bird et al., 1987). (b) 2D geometry used to simulate the experiment. In Table 1, the physical properties of the fluids used in the simulations are listed. In the analyzed case, a Newtonian and two polymeric fluids are considered flowing to an atmosphere containing air. The gravitational acceleration used was -9.8 m/s 2 in Y direction. To the Newtonian fluid was used the viscosity value equal to the sum of the polymer and solvent viscosities (η P + η S ). The difference between the two polymeric fluids analyzed is only on the value of λ parameter. The value of λ is responsible to the deviation of the Newtonian like fluids and then an increase of this value results in an increase of the elasticity phenomena for the same flow conditions. To Newtonian s like fluids the value of λ is assumed as being null. Table 1: Physical properties of fluids in simulations. Fluid Parameters Die Swell ρ[kg/m 3 ] η S [Pa.s] Polymer η P [Pa.s] 1.20 λ [s] 0.03 and 3.0 α [--] 0.15 ρ[kg/m 3 ] 1.0 η S [Pa.s] 0.0 Air η P [Pa.s] 1.48x10-5 λ [s] 0.0 α [--] Results and Discussion Analyzing Figure 2, we can observe three main differences comparing Newtonian and viscoelastic behavior: 1) The occurrence of jet ruptures for the viscoelastic case with high λ value. This could be attributed to the fluid accumulation at the nozzle due to elastic behavior. When there is enough accumulation of polymer a sudden acceleration going down is observed, causing a local increase of elongation rate and producing, in this way, the rupture. When jet break, recoil of fluid is also observed due to elasticity.
5 Simulation of Free Surface Viscoelastic Fluid Flow Using the Software OpenFOAM Newtonian Polymer (λ = 0.03 s) Polymer (λ = 3.0 s) time = 0.5 s time = 1.0 s time = 1.5 s time = 2.0 s time = 2.5 s time = 3.5 s Figure 2: Results for die swell simulation. 2) The viscoelastic fluid presents a jet that oscillates in the X direction, and due to this effect air bubbles are occluded in the mass of fluid. 3) The die swell only happens for the polymeric fluid and it is also noticed that the die swell happens mainly next to the exit of the channel, where exists the relaxation of the polymeric chains.
6 Favero et al. In Figure 3, a zoom on the exit of the channel region is shown for a better visualization of the die swell, together with the respective stress field for the time instant 3.5 s. The larger values of stress happen inside the channel and soon at the channel exit, where the die swell exists. Newtonian Polymer (λ = 0.03 s) Stress field Figure 3: Die swell and stress field at time = 3.5 s. For all the presented simulations the Crank-Nicholson method was used for time derivatives, with zero initial condition being specified for all variables unless the γ field where the value of 1.0 was specified on the channel. The resulting linear discretized systems were solved by conjugated gradient method (CG), using CG with AMG preconditioning for pressure and BiCGstab with an Incomplete Lower-Upper (ILU) preconditioning for γ, velocity and stress. The absolute tolerance for pressure was and for γ, velocity, and stress was Conclusion Simulation results of viscoelastic fluid flow with free surface were presented. The analyzed cases show results with qualitative agreement with experimentally observed. Die swell was observed in the polymer jet at the channel exit, and jet rupture and air bubbles occlusion in the fluid were verified. The obtained results were satisfactory, justifying the usage of the methodology for free-surface viscoelastic fluid flow using the software OpenFOAM. 5. Acknowledgements We want to thanks CAPES for the financial support. References C. Macosko. Rheology: Principles, Measurements and Applications. [S.l.]: VHC, C. W. Hirt and B. D. Nicols. J. Comp. Phys. 1981, 39, D. A. H. Jacobs. Central Electricity Research Laboratories RD/L/N193, 1980, 62. D. Khismatullin; Y. Renardy; M. Renardy. J. Non-Newtonian Fluid Mech. 2006, 140, D.J.E. Harvie, J.J. Cooper-White, M.R. Davidson, J. Non-Newtonian Fluid Mech. 2008, 155, Issues 1-2, F. H. Harlow and J. E. Welch. The mac method. Physics of Fluids, 1965, 8, H. Rusche. Computational fluid dynamics of dispersed two-phase flows at high phase fractions, Phd thesis, Imperial College, University of London, H.G. Weller, G. Tabor, H. Jasak, C. Fureby, Computers in Physics, 1998, 12, 6, J. L. Favero, A. R. Secchi, N. S. C. Cardozo, H. Jasak. Viscoelastic flow simulation: development of a methodology of analysis using the software OpenFOAM and differential constitutive equations. In: 10th International Symposium on Process Systems Engineering, M.F. Tomé; A. Castelo; V.G. Ferreira; S. McKee. J. Non-Newtonian Fluid Mech. 2008, 154, O. Hassager. in: Working group on numerical techniques, in: Proceedings of the fifth workshop on numerical methods in non-newtonian flow. J. Non-Newton. Fluid Mech. 1988, 29, 2-5. O. Ubbink and R.I. Issa, J. Comp. Physics, 1999, 153, R. B. Bird; R. Armstrong; O. Hassager. Dynamics of Polymeric Liquids. John Wiley & Sons, Inc., New York, 1987; 2nd. ed., Vol. 1.
Free Surface Flow Simulations
Free Surface Flow Simulations Hrvoje Jasak h.jasak@wikki.co.uk Wikki Ltd. United Kingdom 11/Jan/2005 Free Surface Flow Simulations p.1/26 Outline Objective Present two numerical modelling approaches for
More informationExample Simulations in OpenFOAM
Example Simulations in OpenFOAM Hrvoje Jasak h.jasak@wikki.co.uk Wikki Ltd, United Kingdom FSB, University of Zagreb, Croatia 18/Nov/2005 Example Simulations in OpenFOAM p.1/26 Outline Objective Present
More informationNumerical Simulations of Planar Extrusion and Fused Filament Fabrication of Non- Newtonian Fluids
ownloaded from orbit.dtu.dk on: Nov 11, 18 Numerical Simulations of Planar Extrusion and Fused Filament Fabrication of Non- Newtonian Fluids Comminal, Raphaël Benjamin; Hattel, Jesper Henri; Spangenberg,
More informationParallelization study of a VOF/Navier-Stokes model for 3D unstructured staggered meshes
Parallelization study of a VOF/Navier-Stokes model for 3D unstructured staggered meshes L. Jofre, O. Lehmkuhl, R. Borrell, J. Castro and A. Oliva Corresponding author: cttc@cttc.upc.edu Centre Tecnològic
More informationDynamic Computational Modeling of the Glass Container Forming Process
Dynamic Computational Modeling of the Glass Container Forming Process Matthew Hyre 1, Ryan Taylor, and Morgan Harris Virginia Military Institute, Lexington, Virginia, USA Abstract Recent advances in numerical
More informationCFD modelling of thickened tailings Final project report
26.11.2018 RESEM Remote sensing supporting surveillance and operation of mines CFD modelling of thickened tailings Final project report Lic.Sc.(Tech.) Reeta Tolonen and Docent Esa Muurinen University of
More informationIMAGE ANALYSIS DEDICATED TO POLYMER INJECTION MOLDING
Image Anal Stereol 2001;20:143-148 Original Research Paper IMAGE ANALYSIS DEDICATED TO POLYMER INJECTION MOLDING DAVID GARCIA 1, GUY COURBEBAISSE 2 AND MICHEL JOURLIN 3 1 European Polymer Institute (PEP),
More informationOpenFOAM: Open Platform for Complex Physics Simulations
OpenFOAM: Open Platform for Complex Physics Simulations Hrvoje Jasak h.jasak@wikki.co.uk, hrvoje.jasak@fsb.hr FSB, University of Zagreb, Croatia Wikki Ltd, United Kingdom 18th October 2007 OpenFOAM: Open
More informationFinal drive lubrication modeling
Final drive lubrication modeling E. Avdeev a,b 1, V. Ovchinnikov b a Samara University, b Laduga Automotive Engineering Abstract. In this paper we describe the method, which is the composition of finite
More informationMESHLESS SOLUTION OF INCOMPRESSIBLE FLOW OVER BACKWARD-FACING STEP
Vol. 12, Issue 1/2016, 63-68 DOI: 10.1515/cee-2016-0009 MESHLESS SOLUTION OF INCOMPRESSIBLE FLOW OVER BACKWARD-FACING STEP Juraj MUŽÍK 1,* 1 Department of Geotechnics, Faculty of Civil Engineering, University
More informationA COUPLED FINITE VOLUME SOLVER FOR THE SOLUTION OF LAMINAR TURBULENT INCOMPRESSIBLE AND COMPRESSIBLE FLOWS
A COUPLED FINITE VOLUME SOLVER FOR THE SOLUTION OF LAMINAR TURBULENT INCOMPRESSIBLE AND COMPRESSIBLE FLOWS L. Mangani Maschinentechnik CC Fluidmechanik und Hydromaschinen Hochschule Luzern Technik& Architektur
More informationTrue 3D CAE visualization of filling imbalance in geometry-balanced runners
True 3D CAE visualization of filling imbalance in geometry-balanced runners C.C. Chien, * C.C. Chiang, W. H. Yang, Vito Tsai and David C.Hsu CoreTech System Co.,Ltd., HsinChu, Taiwan, ROC Abstract The
More informationEffect of Extrudate Swell, Nozzle Shape, and Convergence Zone on Fiber Orientation in Fused Deposition Modeling Nozzle Flow
Effect of Extrudate Swell, Nozzle Shape, and Convergence Zone on Fiber Orientation in Fused Deposition Modeling Nozzle Flow B. P. Heller*, D. E. Smith*, and D. A. Jack* *Department of Mechanical Engineering,
More informationAurélien Thinat Stéphane Cordier 1, François Cany
SimHydro 2012:New trends in simulation - Hydroinformatics and 3D modeling, 12-14 September 2012, Nice Aurélien Thinat, Stéphane Cordier, François Cany Application of OpenFOAM to the study of wave loads
More informationTutorial 17. Using the Mixture and Eulerian Multiphase Models
Tutorial 17. Using the Mixture and Eulerian Multiphase Models Introduction: This tutorial examines the flow of water and air in a tee junction. First you will solve the problem using the less computationally-intensive
More informationOpenFOAM in Wave and Offshore CFD
OpenFOAM in Wave and Offshore CFD Capabilities of the Naval Hydro Pack Hrvoje Jasak Wikki Ltd. United Kingdom Faculty of Mechanical Engineering and Naval Architecture, Uni Zagreb, Croatia University of
More informationDevelopment of Hybrid Fluid Jet / Float Polishing Process
COMSOL Conference - Tokyo 2013 Development of Hybrid Fluid Jet / Float Polishing Process A. Beaucamp, Y. Namba Dept. of Mechanical Engineering, Chubu University, Japan Zeeko LTD, United Kingdom Research
More informationNumerical and theoretical analysis of shock waves interaction and reflection
Fluid Structure Interaction and Moving Boundary Problems IV 299 Numerical and theoretical analysis of shock waves interaction and reflection K. Alhussan Space Research Institute, King Abdulaziz City for
More informationSolving Partial Differential Equations on Overlapping Grids
**FULL TITLE** ASP Conference Series, Vol. **VOLUME**, **YEAR OF PUBLICATION** **NAMES OF EDITORS** Solving Partial Differential Equations on Overlapping Grids William D. Henshaw Centre for Applied Scientific
More informationModelling and numerical simulation of the polymeric extrusion process in textile products
Modelling and numerical simulation of the polymeric extrusion process in textile products Paola F. Antonietti a, Nur Aiman Fadel a, Marco Verani a September 22, 2010 a MOX - Laboratory for Modeling and
More informationA brief description of the particle finite element method (PFEM2). Extensions to free surface
A brief description of the particle finite element method (PFEM2). Extensions to free surface flows. Juan M. Gimenez, L.M. González, CIMEC Universidad Nacional del Litoral (UNL) Santa Fe, Argentina Universidad
More informationOpen Source CFD in Research and Industrial Use
Open Source CFD in Research and Industrial Use p. 1/28 Open Source CFD in Research and Industrial Use OpenFOAM with Examples Hrvoje Jasak h.jasak@wikki.co.uk, hrvoje.jasak@fsb.hr Wikki Ltd, United Kingdom
More informationA MULTI-DOMAIN ALE ALGORITHM FOR SIMULATING FLOWS INSIDE FREE-PISTON DRIVEN HYPERSONIC TEST FACILITIES
A MULTI-DOMAIN ALE ALGORITHM FOR SIMULATING FLOWS INSIDE FREE-PISTON DRIVEN HYPERSONIC TEST FACILITIES Khalil Bensassi, and Herman Deconinck Von Karman Institute for Fluid Dynamics Aeronautics & Aerospace
More informationThree Dimensional Numerical Simulation of Turbulent Flow Over Spillways
Three Dimensional Numerical Simulation of Turbulent Flow Over Spillways Latif Bouhadji ASL-AQFlow Inc., Sidney, British Columbia, Canada Email: lbouhadji@aslenv.com ABSTRACT Turbulent flows over a spillway
More informationAbstract. Die Geometry. Introduction. Mesh Partitioning Technique for Coextrusion Simulation
OPTIMIZATION OF A PROFILE COEXTRUSION DIE USING A THREE-DIMENSIONAL FLOW SIMULATION SOFTWARE Kim Ryckebosh 1 and Mahesh Gupta 2, 3 1. Deceuninck nv, BE-8830 Hooglede-Gits, Belgium 2. Michigan Technological
More informationTHE EFFECT OF COATHANGER DIE MANIFOLD SYMMETRY ON LAYER UNIFORMITY IN MULTILAYER COEXTRUSION
THE EFFECT OF COATHANGER DIE MANIFOLD SYMMETRY ON LAYER UNIFORMITY IN MULTILAYER COEXTRUSION Joseph Dooley, Hyunwoo Kim, Patrick C. Lee, and Robert Wrisley The Dow Chemical Company, Midland, MI Abstract
More informationTransfer and pouring processes of casting by smoothed particle. hydrodynamic method
Transfer and pouring processes of casting by smoothed particle hydrodynamic method M. Kazama¹, K. Ogasawara¹, *T. Suwa¹, H. Ito 2, and Y. Maeda 2 1 Application development div., Next generation technical
More information2.7 Cloth Animation. Jacobs University Visualization and Computer Graphics Lab : Advanced Graphics - Chapter 2 123
2.7 Cloth Animation 320491: Advanced Graphics - Chapter 2 123 Example: Cloth draping Image Michael Kass 320491: Advanced Graphics - Chapter 2 124 Cloth using mass-spring model Network of masses and springs
More informationObject-Oriented CFD Solver Design
Object-Oriented CFD Solver Design Hrvoje Jasak h.jasak@wikki.co.uk Wikki Ltd. United Kingdom 10/Mar2005 Object-Oriented CFD Solver Design p.1/29 Outline Objective Present new approach to software design
More informationOverview and Recent Developments of Dynamic Mesh Capabilities
Overview and Recent Developments of Dynamic Mesh Capabilities Henrik Rusche and Hrvoje Jasak h.rusche@wikki-gmbh.de and h.jasak@wikki.co.uk Wikki Gmbh, Germany Wikki Ltd, United Kingdom 6th OpenFOAM Workshop,
More informationMarine Hydrodynamics Solver in OpenFOAM
Marine Hydrodynamics Solver in OpenFOAM p. 1/14 Marine Hydrodynamics Solver in OpenFOAM Hrvoje Jasak and Henrik Rusche h.jasak@wikki.co.uk, h.rusche@wikki.co.uk Wikki, United Kingdom and Germany 4 December
More informationDriven Cavity Example
BMAppendixI.qxd 11/14/12 6:55 PM Page I-1 I CFD Driven Cavity Example I.1 Problem One of the classic benchmarks in CFD is the driven cavity problem. Consider steady, incompressible, viscous flow in a square
More information(LSS Erlangen, Simon Bogner, Ulrich Rüde, Thomas Pohl, Nils Thürey in collaboration with many more
Parallel Free-Surface Extension of the Lattice-Boltzmann Method A Lattice-Boltzmann Approach for Simulation of Two-Phase Flows Stefan Donath (LSS Erlangen, stefan.donath@informatik.uni-erlangen.de) Simon
More informationInvestigation of cross flow over a circular cylinder at low Re using the Immersed Boundary Method (IBM)
Computational Methods and Experimental Measurements XVII 235 Investigation of cross flow over a circular cylinder at low Re using the Immersed Boundary Method (IBM) K. Rehman Department of Mechanical Engineering,
More informationNon-Newtonian Transitional Flow in an Eccentric Annulus
Tutorial 8. Non-Newtonian Transitional Flow in an Eccentric Annulus Introduction The purpose of this tutorial is to illustrate the setup and solution of a 3D, turbulent flow of a non-newtonian fluid. Turbulent
More informationCharacteristic Aspects of SPH Solutions
Characteristic Aspects of SPH Solutions for Free Surface Problems: Source and Possible Treatment of High Frequency Numerical Oscillations of Local Loads. A. Colagrossi*, D. Le Touzé & G.Colicchio* *INSEAN
More informationComputation of Velocity, Pressure and Temperature Distributions near a Stagnation Point in Planar Laminar Viscous Incompressible Flow
Excerpt from the Proceedings of the COMSOL Conference 8 Boston Computation of Velocity, Pressure and Temperature Distributions near a Stagnation Point in Planar Laminar Viscous Incompressible Flow E. Kaufman
More informationConjugate Simulations and Fluid-Structure Interaction In OpenFOAM
Conjugate Simulations and Fluid-Structure Interaction In OpenFOAM Hrvoje Jasak h.jasak@wikki.co.uk Wikki Ltd, United Kingdom and FSB, University of Zagreb, Croatia 7-9th June 2007 Conjugate Simulations
More informationRealistic Animation of Fluids
1 Realistic Animation of Fluids Nick Foster and Dimitris Metaxas Presented by Alex Liberman April 19, 2005 2 Previous Work Used non physics-based methods (mostly in 2D) Hard to simulate effects that rely
More informationSELECTIVE ALGEBRAIC MULTIGRID IN FOAM-EXTEND
Student Submission for the 5 th OpenFOAM User Conference 2017, Wiesbaden - Germany: SELECTIVE ALGEBRAIC MULTIGRID IN FOAM-EXTEND TESSA UROIĆ Faculty of Mechanical Engineering and Naval Architecture, Ivana
More informationIntroduction to OpenFOAM at SIMDI 06
Introduction to OpenFOAM at SIMDI 06 Hrvoje Jasak h.jasak@wikki.co.uk Wikki Ltd, United Kingdom Introduction to OpenFOAM at SIMDI 06 p.1/20 Open Source CFD Platform OpenFOAM: Open Source Computational
More informationA Contact Angle Model for the Parallel Free Surface Lattice Boltzmann Method in walberla Stefan Donath (stefan.donath@informatik.uni-erlangen.de) Computer Science 10 (System Simulation) University of Erlangen-Nuremberg
More informationPublic Release: Native Overset Mesh in FOAM-Extend
Public Release: Native Overset Mesh in FOAM-Extend Vuko Vukčević and Hrvoje Jasak Faculty of Mechanical Engineering and Naval Architecture, Uni Zagreb, Croatia Wikki Ltd. United Kingdom 5th OpenFOAM UK
More informationSimulation of Droplet Impingement on a Solid Surface by the Level Set Method
Simulation of Droplet Impingement on a Solid Surface by the Level Set Method Junling Hu *1, Ruoxu Jia 1, Kai-tak Wan 2, Xingguo Xiong 3 1 Department of Mechanical Engineering, University of Bridgeport,
More informationViscoelastic Registration of Medical Images
Viscoelastic Registration of Medical Images Zhao Yi Justin Wan Abstract Since the physical behavior of many tissues is shown to be viscoelastic, we propose a novel registration technique for medical images
More informationFinite Volume Methodology for Contact Problems of Linear Elastic Solids
Finite Volume Methodology for Contact Problems of Linear Elastic Solids H. Jasak Computational Dynamics Ltd. Hythe House 200 Shepherds Bush Road London W6 7NY, England E-mail: h.jasak@cd.co.uk H.G. Weller
More informationPrinciples and Goals
Simulations of foam rheology Simon Cox Principles and Goals Use knowledge of foam structure to predict response when experiments are not easy to isolate causes of certain effects to save time in designing
More informationNumerical Study of Turbulent Flow over Backward-Facing Step with Different Turbulence Models
Numerical Study of Turbulent Flow over Backward-Facing Step with Different Turbulence Models D. G. Jehad *,a, G. A. Hashim b, A. K. Zarzoor c and C. S. Nor Azwadi d Department of Thermo-Fluids, Faculty
More informationSERBIATRIB 15 STATIC PERFORMANCE OF SURFACE TEXTURED MAGNETORHEOLOGICAL FLUID JOURNAL BEARINGS. 14 th International Conference on Tribology
Serbian Tribology Society SERBIATRIB 15 14 th International Conference on Tribology Belgrade, Serbia, 13 15 May 015 University of Belgrade, Faculty of Mechanical Engineering STATIC PERFORMANCE OF SURFACE
More informationExperimental Validation of the Computation Method for Strongly Nonlinear Wave-Body Interactions
Experimental Validation of the Computation Method for Strongly Nonlinear Wave-Body Interactions by Changhong HU and Masashi KASHIWAGI Research Institute for Applied Mechanics, Kyushu University Kasuga
More informationEOF Library: Open-Source Elmer and OpenFOAM Coupler for Simulation of MHD With Free Surface
XVIII International UIE-Congress Electrotechnologies for Material Processing Hannover (Germany), June 6-9, 2017 EOF Library: Open-Source Elmer and OpenFOAM Coupler for Simulation of MHD With Free Surface
More informationFaculty of Mechanical and Manufacturing Engineering, University Tun Hussein Onn Malaysia (UTHM), Parit Raja, Batu Pahat, Johor, Malaysia
Applied Mechanics and Materials Vol. 393 (2013) pp 305-310 (2013) Trans Tech Publications, Switzerland doi:10.4028/www.scientific.net/amm.393.305 The Implementation of Cell-Centred Finite Volume Method
More informationSPH: Towards the simulation of wave-body interactions in extreme seas
SPH: Towards the simulation of wave-body interactions in extreme seas Guillaume Oger, Mathieu Doring, Bertrand Alessandrini, and Pierre Ferrant Fluid Mechanics Laboratory (CNRS UMR6598) Ecole Centrale
More informationDynamic Mesh Handling in OpenFOAM
Dynamic Mesh Handling in OpenFOAM p. 1/18 Dynamic Mesh Handling in OpenFOAM Hrvoje Jasak h.jasak@wikki.co.uk, hrvoje.jasak@fsb.hr Wikki Ltd, United Kingdom and FSB, University of Zagreb, Croatia 47th AIAA
More informationNavier-Stokes & Flow Simulation
Last Time? Navier-Stokes & Flow Simulation Implicit Surfaces Marching Cubes/Tetras Collision Detection & Response Conservative Bounding Regions backtracking fixing Today Flow Simulations in Graphics Flow
More informationCalculate a solution using the pressure-based coupled solver.
Tutorial 19. Modeling Cavitation Introduction This tutorial examines the pressure-driven cavitating flow of water through a sharpedged orifice. This is a typical configuration in fuel injectors, and brings
More informationTHREE-DIMENSIONAL CAE OF WIRE-SWEEP IN MICROCHIP ENCAPSULATION
THREE-DIMENSIONAL CAE OF WIRE-SWEEP IN MICROCHIP ENCAPSULATION Wen-Hsien Yang *, David C.Hsu and Venny Yang CoreTech System Co.,Ltd., HsinChu, Taiwan, ROC Rong-Yeu Chang National Tsing-Hua University,
More informationSteady Flow: Lid-Driven Cavity Flow
STAR-CCM+ User Guide Steady Flow: Lid-Driven Cavity Flow 2 Steady Flow: Lid-Driven Cavity Flow This tutorial demonstrates the performance of STAR-CCM+ in solving a traditional square lid-driven cavity
More informationThe solution of viscous incompressible jet flows using non-staggered boundary fitted co-ordinate methods
INTERNATIONAL JOURNAL FOR NUMERICAL METHODS IN FLUIDS Int. J. Numer. Meth. Fluids 2001; 35: 71 91 The solution of viscous incompressible jet flows using non-staggered boundary fitted co-ordinate methods
More informationMultiphase flow metrology in oil and gas production: Case study of multiphase flow in horizontal tube
Multiphase flow metrology in oil and gas production: Case study of multiphase flow in horizontal tube Deliverable 5.1.2 of Work Package WP5 (Creating Impact) Authors: Stanislav Knotek Czech Metrology Institute
More information2D Flow Analysis of Film Casting Process
Article Journal of the Society of Rheology, Japan Vol.31, No.3, 149 ~ 155 (2003) (Nihon Reoroji Gakkaishi) 2003 The Society of Rheology, Japan 2D Flow Analysis of Film Casting Process Hisahiro ITO *, Masao
More informationNumerical Simulation of 3-D Cavitation behind a Disk Cavitator Using OpenFOAM
The 1 th Iranian Aerospace Society Conference Amir Kabir University of Technology AERO013-18514 Numerical of 3-D Cavitation behind a Disk Cavitator Using OpenFOAM Amin Rahimi, Ehsan Roohi, Mohammad Javad
More informationSecond OpenFOAM Workshop: Welcome and Introduction
Second OpenFOAM Workshop: Welcome and Introduction Hrvoje Jasak h.jasak@wikki.co.uk Wikki Ltd, United Kingdom and FSB, University of Zagreb, Croatia 7-9th June 2007 Second OpenFOAM Workshop:Welcome and
More informationEXPLICIT AND IMPLICIT TVD AND ENO HIGH RESOLUTION ALGORITHMS APPLIED TO THE EULER AND NAVIER-STOKES EQUATIONS IN THREE-DIMENSIONS RESULTS
EXPLICIT AND IMPLICIT TVD AND ENO HIGH RESOLUTION ALGORITHMS APPLIED TO THE EULER AND NAVIER-STOKES EQUATIONS IN THREE-DIMENSIONS RESULTS Edisson Sávio de Góes Maciel, edissonsavio@yahoo.com.br Mechanical
More informationThe 3D DSC in Fluid Simulation
The 3D DSC in Fluid Simulation Marek K. Misztal Informatics and Mathematical Modelling, Technical University of Denmark mkm@imm.dtu.dk DSC 2011 Workshop Kgs. Lyngby, 26th August 2011 Governing Equations
More informationSimulation of Flow Development in a Pipe
Tutorial 4. Simulation of Flow Development in a Pipe Introduction The purpose of this tutorial is to illustrate the setup and solution of a 3D turbulent fluid flow in a pipe. The pipe networks are common
More informationAbstract. Introduction. Numerical Techniques for Coextrusion Simulation
COMPARISON OF MESH PARTITIONING TECHNIQUE WITH LEVEL-SET METHOD FOR COEXTRUSION SIMULATION Mahesh Gupta 1, 2 1. Michigan Technological University, Houghton, MI 49931 2. Plastic Flow, LLC, Hancock, MI 49930
More informationNumerical simulations of viscoelastic flows with free surfaces
Numerical simulations of viscoelastic flows with free surfaces R. COMMINAL a, J. SPANGENBERG b, J.H. HATTEL a a. Technical University of Denmark (DTU), Produktionstorvet, 2800 KGS. LYNGBY (DENMARK) b.
More informationMicrowell Mixing with Surface Tension
Microwell Mixing with Surface Tension Nick Cox Supervised by Professor Bruce Finlayson University of Washington Department of Chemical Engineering June 6, 2007 Abstract For many applications in the pharmaceutical
More informationNumerical Modelling in Continuum Mechanics
Numerical Modelling in Continuum Mechanics Hrvoje Jasak h.jasak@wikki.co.uk Wikki Ltd. United Kingdom 22/Mar/2005 Numerical Modelling in Continuum Mechanics p.1/31 Outline Objective Present a new way of
More informationOpenFOAM: A C++ Library for Complex Physics Simulations
OpenFOAM: A C++ Library for Complex Physics Simulations Hrvoje Jasak Aleksandar Jemcov and Željko Tuković h.jasak@wikki.co.uk Wikki Ltd, United Kingdom FSB, University of Zagreb, Croatia Development Department,
More informationUsing of open source code library OpenFOAM for 3D magnetohydrodynamic calculations in semiconductor crystal growth technologies
International Scientific Colloquium Modelling for Electromagnetic Processing Hannover, October 27-29, 2008 Using of open source code library OpenFOAM for 3D magnetohydrodynamic calculations in semiconductor
More informationCFD Simulation for Stratified Oil-Water Two-Phase Flow in a Horizontal Pipe
CFD Simulation for Stratified Oil-Water Two-Phase Flow in a Horizontal Pipe Adib Zulhilmi Mohd Alias, a, Jaswar Koto, a,b,* and Yasser Mohamed Ahmed, a a) Department of Aeronautics, Automotive and Ocean
More informationSimulation of Freak Wave Impact Using the Higher Order Spectrum
Simulation of Freak Wave Impact Using the Higher Order Spectrum The Naval Hydro Pack Hrvoje Jasak and Vuko Vukčević Faculty of Mechanical Engineering and Naval Architecture, Uni Zagreb, Croatia Wikki Ltd.
More informationMulti-Physics Simulations in Continuum Mechanics
Multi-Physics Simulations in Continuum Mechanics Hrvoje Jasak h.jasak@wikki.co.uk Wikki Ltd, United Kingdom FSB, University of Zagreb, Croatia Multi-Physics Simulations in Continuum Mechanics p.1/22 Outline
More informationNumerical Estimation and Validation of Shallow Draft Effect on Roll Damping
The 14 th International Ship Stability Workshop (ISSW), 29 th September- 1 st October 2014, Kuala Lumpur, Malaysia Numerical Estimation and Validation of Shallow Draft Effect on Roll Damping Toru Katayama
More informationFlow and Heat Transfer in a Mixing Elbow
Flow and Heat Transfer in a Mixing Elbow Objectives The main objectives of the project are to learn (i) how to set up and perform flow simulations with heat transfer and mixing, (ii) post-processing and
More informationSolution for Euler Equations Lagrangian and Eulerian Descriptions
Solution for Euler Equations Lagrangian and Eulerian Descriptions Valdir Monteiro dos Santos Godoi valdir.msgodoi@gmail.com Abstract We find an exact solution for the system of Euler equations, following
More informationAvailable online at ScienceDirect. Procedia Engineering 136 (2016 ) Dynamic analysis of fuel tank
Available online at www.sciencedirect.com ScienceDirect Procedia Engineering 136 (2016 ) 45 49 The 20 th International Conference: Machine Modeling and Simulations, MMS 2015 Dynamic analysis of fuel tank
More informationAn Overview of Computational Fluid Dynamics
An Overview of Computational Fluid Dynamics Dr. Nor Azwadi bin Che Sidik Faculty of Mechanical Engineering Universiti Teknologi Malaysia INSPIRING CREATIVE AND INNOVATIVE MINDS 1 What is CFD? C computational
More informationUse of CFD in Design and Development of R404A Reciprocating Compressor
Purdue University Purdue e-pubs International Compressor Engineering Conference School of Mechanical Engineering 2006 Use of CFD in Design and Development of R404A Reciprocating Compressor Yogesh V. Birari
More informationEulerian Techniques for Fluid-Structure Interactions - Part II: Applications
Published in Lecture Notes in Computational Science and Engineering Vol. 103, Proceedings of ENUMATH 2013, pp. 755-762, Springer, 2014 Eulerian Techniques for Fluid-Structure Interactions - Part II: Applications
More informationFinite Volume Discretization on Irregular Voronoi Grids
Finite Volume Discretization on Irregular Voronoi Grids C.Huettig 1, W. Moore 1 1 Hampton University / National Institute of Aerospace Folie 1 The earth and its terrestrial neighbors NASA Colin Rose, Dorling
More information2 CFD model. 1 Introduction
Open Eng. 2015; 5:274 279 Symkom 2014 Open Access Alejandro Lopez*, Matthew Stickland, and William Dempster Modeling erosion in a centrifugal pump in an Eulerian-Lagrangian frame using OpenFOAM DOI 10.1515/eng-2015-0037
More information2D numerical simulation of ocean waves
2D numerical simulation of ocean waves Qingjie. Du,*, Y.C. Dennis. Leung Department of Mechanical Engineering, The University of Hong Kong, Hong Kong, China * Corresponding author. Tel: +852 51743593,
More informationThe Development of a Navier-Stokes Flow Solver with Preconditioning Method on Unstructured Grids
Proceedings of the International MultiConference of Engineers and Computer Scientists 213 Vol II, IMECS 213, March 13-15, 213, Hong Kong The Development of a Navier-Stokes Flow Solver with Preconditioning
More informationCGT 581 G Fluids. Overview. Some terms. Some terms
CGT 581 G Fluids Bedřich Beneš, Ph.D. Purdue University Department of Computer Graphics Technology Overview Some terms Incompressible Navier-Stokes Boundary conditions Lagrange vs. Euler Eulerian approaches
More informationStratified Oil-Water Two-Phases Flow of Subsea Pipeline
Stratified Oil-Water Two-Phases Flow of Subsea Pipeline Adib Zulhilmi Mohd Alias, a, Jaswar Koto, a,b,*, Yasser Mohamed Ahmed, a and Abd Khair Junaidi, b a) Department of Aeronautics, Automotive and Ocean
More informationApplication of Finite Volume Method for Structural Analysis
Application of Finite Volume Method for Structural Analysis Saeed-Reza Sabbagh-Yazdi and Milad Bayatlou Associate Professor, Civil Engineering Department of KNToosi University of Technology, PostGraduate
More informationOpenFOAM Library for Fluid Structure Interaction
OpenFOAM Library for Fluid Structure Interaction 9th OpenFOAM Workshop - Zagreb, Croatia Željko Tuković, P. Cardiff, A. Karač, H. Jasak, A. Ivanković University of Zagreb Faculty of Mechanical Engineering
More informationA Particle Cellular Automata Model for Fluid Simulations
Annals of University of Craiova, Math. Comp. Sci. Ser. Volume 36(2), 2009, Pages 35 41 ISSN: 1223-6934 A Particle Cellular Automata Model for Fluid Simulations Costin-Radu Boldea Abstract. A new cellular-automaton
More informationExample 24 Spring-back
Example 24 Spring-back Summary The spring-back simulation of sheet metal bent into a hat-shape is studied. The problem is one of the famous tests from the Numisheet 93. As spring-back is generally a quasi-static
More informationInvestigation of the critical submergence at pump intakes based on multiphase CFD calculations
Advances in Fluid Mechanics X 143 Investigation of the critical submergence at pump intakes based on multiphase CFD calculations P. Pandazis & F. Blömeling TÜV NORD SysTec GmbH and Co. KG, Germany Abstract
More informationVOLCANIC DEFORMATION MODELLING: NUMERICAL BENCHMARKING WITH COMSOL
VOLCANIC DEFORMATION MODELLING: NUMERICAL BENCHMARKING WITH COMSOL The following is a description of the model setups and input/output parameters for benchmarking analytical volcanic deformation models
More informationCFD MODELING FOR PNEUMATIC CONVEYING
CFD MODELING FOR PNEUMATIC CONVEYING Arvind Kumar 1, D.R. Kaushal 2, Navneet Kumar 3 1 Associate Professor YMCAUST, Faridabad 2 Associate Professor, IIT, Delhi 3 Research Scholar IIT, Delhi e-mail: arvindeem@yahoo.co.in
More informationDie Wear Profile Investigation in Hot Forging
Die Wear Profile Investigation in Hot Forging F. R. Biglari, M Zamani Abstract In this study, the wear profile on the die surface during the hot forging operation for an axisymmetric cross-section is examined.
More informationFEMLAB Exercise 1 for ChE366
FEMLAB Exercise 1 for ChE366 Problem statement Consider a spherical particle of radius r s moving with constant velocity U in an infinitely long cylinder of radius R that contains a Newtonian fluid. Let
More informationSimulation of Turbulent Axisymmetric Waterjet Using Computational Fluid Dynamics (CFD)
Simulation of Turbulent Axisymmetric Waterjet Using Computational Fluid Dynamics (CFD) PhD. Eng. Nicolae MEDAN 1 1 Technical University Cluj-Napoca, North University Center Baia Mare, Nicolae.Medan@cunbm.utcluj.ro
More informationAnalysis of the Flow in Hermetic Compressor Valves Using the Immersed Boundary Method
Purdue University Purdue e-pubs International Compressor Engineering Conference School of Mechanical Engineering 010 Analysis of the Flow in Hermetic Compressor Valves Using the Immersed Boundary Method
More informationSTCE. An (more) effective Discrete Adjoint Model for OpenFOAM
An (more) effective Discrete Adjoint Model for OpenFOAM Markus Towara, Uwe Naumann Software and Tools for Computational Engineering Science RWTH Aachen University EuroAD 2013, Oxford, 10. December 2013
More information