3D simulations of concrete penetration using SPH formulation and the RHT material model
|
|
- Geraldine Blake
- 5 years ago
- Views:
Transcription
1 3D simulations of concrete penetration using SPH formulation and the RHT material model H. Hansson Weapons and Protection, Swedish Defence Research Agency (FOI), Sweden Abstract This paper describes work performed with the RHT concrete model, which shows promising behaviour for penetration/perforation simulations in concrete. The three dimensional simulations, using both Lagrange and SPH formulations, consider cases with varying impact conditions and target configurations. The simulations that consider normal impact conditions are compared with earlier benchmark tests. Keywords: numerical simulation, concrete penetration, RHT model, SPH, smooth particle hydrodynamics, meshless. 1 Introduction It is necessary to predict penetration depths in concrete targets to determine the vulnerability of underground structures. Several empirical and numerical tools have been developed to predict penetration depths of projectiles in concrete. Previously presented 2D simulations by Hansson [1] are extended here to 3D cases. An advanced material model is used to describe the material behaviour of concrete in this study, i.e. the RHT material model developed at EMI, see Riedel [2]. The material model is then combined with Lagrange and Smooth Particle Hydrodynamics (SPH) numerical formulations to study projectile penetration in concrete targets. A benchmark penetration test set-up is used for the initial 3D models, and the simulations are then modified to consider non-normal impact and reinforced concrete targets. The use of a 3D software package allows the simulation of non-symmetric impact cases.
2 212 Structures Under Shock and Impact VIII 2 Benchmark tests A benchmark test series with normal impact of 152 mm projectiles was conducted in These test data are used for comparison with the numerical simulations considering normal impact conditions. The exit velocity of the projectiles was determined with a high-speed video camera. The properties of the concrete targets are compiled in table 1, and the benchmark test data in table 2, see Hansson [1, 3, 4]. A target after perforation is shown in figure 1. Table 1: Properties of the concrete targets. Target/concrete properties Diameter Length f c, mm cylinders Tensile splitting strength, 150 mm cubes E c for mm cylinders Value 2.40 m 0.75 m 92 ± 2 MPa 6.5 ± 0.2 MPa 44.5 ± 0.9 GPa Table 2: Benchmark test data. Test No. 23 No. 24 No. 25 Mean value Projectile properties Diameter 152 mm, length 552 mm, ogive radius 380 mm, total mass 46.2 ±0.1 kg, case mass 38.8 kg V Impact (m/s) ± ± ± ±0. 2 V Exit (m/s) 183 ±6 204 ±4 181 ±4 190 ±14 3 Material modelling The RHT material model is implemented in the general release of Autodyn 4.2 or higher, and the model is presented by Riedel [2]. However, some modifications to the material model were made before the implementation in Autodyn. Earlier simulations with the material model have been presented by e.g. Riedel et al. [5]. Figure 1: Target after perforation for test no. 24, front face to the left.
3 Structures Under Shock and Impact VIII 213 The material model uses three strength surfaces, i.e. elastic limit surface, failure surface and remaining strength surface for the crushed material. There is also an option to use a cap on the elastic strength surface. The material model is briefly described by Hansson [1, 3, 4], and the material parameters used are given in table 3. The cap option is activated for all simulations in this study. The values of the material parameters chosen for the RHT model were based on unconfined and confined compressive strength, tensile splitting strength and estimations based on similar concrete types. The deviatoric strength model is combined with the P-α equation of state, see Herrmann [6], to obtain the concrete response to hydrostatic pressure, see figure 2. Table 3: Common parameters for simulations with the RHT concrete model. Parameter Value Parameter Value Parameter Value G 18 GPa BQ B 1.6 f c 92 MPa D M 0.61 f t /f c D 2 1 α (for F RATE ) f s /f c 0.30 EFMIN 0.05 δ A fail 1.9 PREFACT 2 SHRATD 0.13 N fail 0.6 TENSRAT 0.80 Q COMPRAT 0.75 A piece-wise linear strain hardening model with thermal softening and strain rate dependence together with a linear equation of state are used for the steel rebars. The material s strain hardening is based on quasi-static testing of B500BT type 1 rebar steel with 16 mm diameter. The stress-strain relationship for a representative steel bar and the approximation used for the numerical model are shown in figure 3. The material model uses the same strain rate dependence and thermal softening as the Johnson and Cook [7] model for 4340 steel Pressure (MPa) Experimental data from GREAC test performed at FFI Density (g/cc) Figure 2: Hydrostatic loading and unloading path for the concrete.
4 214 Structures Under Shock and Impact VIII Engineering stress (MPa) Rebar no Numerical model Engineering strain (mm/mm) Figure 3: Stress vs. strain for B500BT type 1 bars. 4 Three dimensional numerical simulations The simulations of concrete perforation were performed with Autodyn 3D version for the Lagrange models, and version for the SPH models. Hansson [4] has presented further data from the simulations. The numerical simulations were performed with Lagrange and SPH formulations for comparison. For the Lagrange formulation it is necessary to use numerical erosion, and the value 1.5 was used for the erosion strain for Lagrange models. However, this reduces the confinement in the vicinity of the projectile. Concrete has a pressure dependent yield stress and failure type, and the calculation results are therefore likely to be influenced by the use of numerical erosion. The use of e.g. Euler and SPH formulations do not require numerical erosion. 4.1 Model geometry The general model geometry of the target is a cylinder with 1.2 m radius and 0.75 m length. However, this geometry is modified for several models, e.g. for the study of reinforced targets where a rectangular cross section with 2.0 m sides is used instead. The target length for the model can vary a small amount depending on the size chosen for the SPH nodes, e.g. 20 mm nodes can not be equally divided into 750 mm. This is assumed to have negligible effects on the overall behaviour of the models. A free surface boundary condition is applied to all target surfaces. Exceptions from these default values are given in the tables with model descriptions and results. The 3D Lagrange models used a graded element mesh. A constant element size of either 10 or 5 mm was used for the central part of the target; with the radius of 50 cm. Graded elements with the size increased from 10 to 41.1 mm, or from 5 to 23.6 mm, were used for the outer part of the Lagrange models. This limits the number of elements far away from
5 Structures Under Shock and Impact VIII 215 the impact, and thus reduces the computational time considerably and with negligible effect on the projectile penetration path. A Lagrange mesh is used for the projectile in all 3D simulations. The total length of the projectile is 559 mm divided into a cylindrical part and an ogive nose part. The cylindrical part has a length of 324 mm and a radius of 76 mm, while the ogive nose radius is 380 mm. The element mesh size is about 21.5 mm and 7.4 mm parallel to and transverse to the projectile axis, respectively. In the benchmark test, the inner part of the projectile was instrumented with accelerometers. Thus, in order to obtain the correct projectile mass for the simulations the inner part of the projectile was modelled with a fictional material. 4.2 Lagrange simulations Penetration simulations using three-dimensional models, with the use of Lagrange formulation for both target and projectile meshes, are compiled in tables 4 and 5. 3D models allow problem geometries with e.g. varying impact angle or yaw/pitch with the use of half symmetry models. Thus, a minor study of the effects of different impact conditions for the projectile trajectory was performed. Friction between projectile and target are not considered in the presented simulations, except for models B99309 and B Table 4: Effects of friction and element size on the exit velocity. Model id. B99311 B99312 B99307 B99309 Element type / size Lagrange / 10 mm Lagrange / 5 mm Symmetry ¼ Friction coefficient Energy error 1.9% 8.0% 1.9% 8.5% Exit velocity 217 m/s 205 m/s 225 m/s 213 m/s As shown, the projectile speed is around 220 m/s after penetration for the majority of models. Furthermore, as in the earlier study of the 2D case presented by Hansson [1, 4], introducing a friction coefficient significantly affects the energy error. It is also seen, that decreasing the elements side length from 10 mm to 5 mm only results in a minor increase of the exit velocity of about 8 m/s. The main advantage of 3D models is the possibility of simulating oblique impact and other cases where non-symmetric models can be used. In table 5 the different impact cases are listed together with the simulation results. From the table it is first noted that at normal impact using ¼ or ½ symmetry results in a similar exit velocity, as expected. However, the small deviation of 1 between projectile axis and velocity vector gives a rather large effect on the projectile trajectory and the exit velocity decreases by 25 m/s to 186 m/s compared to the case with normal impact. An oblique impact angle causes different pressures on the upper and lower side of the projectile and as a consequence an increasing curvature of the trajectory. At exit, the absolute value of the velocity for model B99323 was decreased to 111 m/s.
6 216 Structures Under Shock and Impact VIII Table 5: Effects of geometry and impact angle on the exit velocity. Model id. B99320 B99321 B99323 B99311 Element type / size Lagrange / 10 mm Symmetry ½ ¼ Impact condition Normal impact Yaw=1 Impact angle 60 Normal impact Energy error 1.9% 1.9% 2.1% 1.9% Exit velocity 211 m/s 186 m/s 111 m/s 217 m/s 4.3 SPH simulations The focus of this part of the study was to evaluate the possibilities to use the SPH formulation for concrete targets in 3D penetration simulations. Simulations were performed both with one or two symmetry planes, different node sizes, different boundary conditions, with and without reinforcement, and different impact angles for the projectile. Friction between projectile and target was not considered for the SPH simulations. The SPH models with unreinforced targets are compiled in table 6. Comparing the models SPH000 and SPH204 show that for a normal impact condition the two symmetry cases give almost equal exit velocity. The advantage of the half symmetry model is the possibility to model non-normal impact events, e.g. oblique impact, as for models SPH200 and SPH203. The latter model uses a decreased node size to study the influence from this numerical parameter, see table 6. From this table it can be seen that both target size and the size of SPH nodes influence the exit velocity. The calculated damage evaluation in the target and the location of the projectile for the model SPH200 with 60 impact angle are shown in figure 4. Table 6: Unreinforced SPH models performed in the study. Model id. SPH000 SPH204 SPH200 SPH203 SPH206 Symmetry ¼ ½ Target type 2.4 m 3.0 m Target length 760 mm 750 mm 760 mm SPH node size 20 mm 12.5 mm 20 mm SPH nodes 103, , , ,452 Impact angle Energy error 5.1% 6.2% 12.2% 10.6% 6.2% Exit velocity 199 m/s 203 m/s 164 m/s 144 m/s 185 m/s Reinforcement was simulated with beam elements for front face and back face reinforcement ( 25 mm), and with truss elements for the longitudinal rebars ( 10 mm). The total number of beam and truss elements for the reinforcement was 1,812. The calculated SPH models with reinforced targets are compiled in table 7, i.e. models SPH220-SPH223 and SPH226. From this table and the previous table 6 it can be seen that the reinforcement decreases the calculated exit velocity by 15 to 30 m/s, depending on the impact angle. By
7 Structures Under Shock and Impact VIII 217 varying the impact point and impact angle of the projectile, and the location of reinforcement bars, an almost unlimited number of penetration cases can be simulated. Depending on the local geometry, and the interaction between projectile, concrete and rebars, these penetration cases are likely to result in different exit velocities. The calculated damage evaluation in the target and the status for the reinforcement for the reinforced model SPH221 with 60 impact angle are shown in figure 5. Figure 4: Calculated damage propagation in concrete target during penetration for model SPH200 at 1.2, 2.4 and 3.6 ms after impact. Table 7: Reinforced SPH models performed in the study. Model id. SPH220 SPH223 SPH221 SPH222 SPH226 Symmetry ½ Target type Rectangular with 2 m side Target length 760 mm 750 mm SPH node size 20 mm 12.5 mm SPH nodes 190, ,800 Impact angle Boundary condition Free surface Constrained target Free surface Energy error 8.3% 6.9% 9.5% 5.4% 2.7% Exit velocity 168 m/s 177 m/s 149 m/s 88 m/s 180 m/s The influence of decreased SPH node size was tested with model SPH226. However, there does not seem to be any significant difference in exit velocity between the models SPH223 and SPH226. For the unreinforced models the exit velocity decreased by approximately 20 m/s when the node size was decreased. Model SPH222 used a constrained boundary condition for confinement of the target, which allowed the surface to move within ±1 mm in the normal direction. The use of a constrained boundary condition for the target greatly decreased the exit velocity of the projectile. This is likely to be caused by the increased confinement of the target and projectile.
8 218 Structures Under Shock and Impact VIII Figure 5: Calculated concrete damage and reinforcement deformations for model SPH221 with target tilted 30 at 3.0 and 5.0 ms after impact. 5 Discussion and summary In general the simulations gave reasonable results for the different simulation cases. The decrease of energy for the projectile is relatively constant for the models, with only small variations depending on the model parameters varied. However, to be able to predict warhead performance against hardened structures of different types it is necessary to verify the use of these types of models for other projectile geometries, target configurations and materials. 3D simulations using the SPH formulation for the concrete targets, and the RHT concrete model results in a realistic interaction between projectile and target. Both Euler and SPH formulations make it possible to retain both the
9 Structures Under Shock and Impact VIII 219 material of the target and confinement around the projectile during the simulation. With these methods it is possible to start to identify problems regarding the material descriptions. For the simulations performed using a Lagrangian element formulation it is difficult to distinguish between errors caused by numerical problems, i.e. from distorted elements and erosion, and errors caused by the material models. It is clear that the 3D simulations can give additional and valuable information considering projectile penetration, where the 2D restriction to symmetric cases causes limitations. The use of 3D models allows oblique impact, as well as simulations with varying yaw and pitch, and must be considered necessary to predict the interaction between target and projectile. Simulations show that initial yaw and/or pitch of the projectile will result in increased stresses in the projectile during the penetration phase due to lateral forces. It is also important to note that a projectile without yaw or pitch and with a normal impact angle normally starts to rotate in the target. This is caused by inhomogeneities in the concrete and unsymmetric failure initiation in the target. Considering the concrete material description, the RHT model is promising. The strength is modelled by three surfaces, representing elastic limit, failure surface and finally a residual strength of the damaged material under compression. Furthermore, apart from pressure, the strength surfaces are dependent on the strain rate and the tri-axial stress state. However, to be able to predict penetration depths in concrete it is important that correct material properties are determined for the material used. This requires extensive laboratory testing at high pressures and deformation rates of the concrete type used. This material data should then be used to evaluate the material models and determine the values for the material parameters to be used in the models. Enhancement of the material models with statistical strength or failure strain is likely to improve the behaviour of several types of numerical models. In many cases the material cannot be considered homogeneous when fracturing and fragmentation are considered. Further improvement of the damage evolution models and determination of the residual strength of concrete are two major areas that should be considered for future research. These modifications to the material model will in the future enhance the probability to predict effects from penetrating warheads with large length to diameter ratios, dual charge warheads and multiple impact attacks on hardened concrete structures. During the penetration of a reinforced concrete target it is likely that rebars prohibit radial expansion and cracking, which results in a reduced penetration depth in relatively small targets. For large concrete targets it is therefore likely that the reduction of the penetration depths may be small for a reinforced target, when compared to an unreinforced target. The penetration depth is normally decreased when the size of the target is increased, especially if unconfined and unreinforced concrete targets are used. To obtain a lower limit for the penetration depths it is necessary to use unrealistically large concrete targets, therefore it is recommended that confined targets should be used for penetration tests. This ensures that the boundary conditions are known and it also reduces the radial expansion of relatively small targets. This study showed that the choice of
10 220 Structures Under Shock and Impact VIII suitable boundary conditions may be one of the most important considerations for the numerical models. This also applies to the design of penetration experiments if good quality data is to be obtained. For these ballistic experiments it is important that the boundary conditions are well defined and that the influence of the target size is known. References [1] Hansson, H., Modelling of concrete perforation. Proc. of Structures under Shock and Impact VII, WIT Press Southampton, pp , [2] Riedel, W., Beton unter dynamishen lasten, Meso- und makromechanische modelle und ihre parameter, EMI-Bericht 6/00, EMI Freiburg, [3] Hansson, H., Numerical simulation of concrete penetration with Euler and Lagrange formulation, FOI-R SE, FOI Tumba, [4] Hansson, H., 2D and 3D Simulations of Concrete Penetration using the RHT Material Model, FOI-R SE, FOI Tumba, [5] Riedel, W., Thoma K, Hiermaier S, Schmolinske E, Penetration of Reinforced Concrete by BETA-B-500. Numerical Analysis using a New Macroscopic Concrete Model for Hydrocodes. Proc. of 9 th Int. Symp. on Interaction of the Effects of Munitions with Structures, pp , [6] Herrmann, W., Constitutive Equation for the Dynamic Compaction of Ductile Porous Materials. Journal of Applied Physics, Vol 40, No 6, pp , [7] Johnson, G. R. and Cook, W.H., A constitutive model and data for metals subjected to large strains, high strain rates, and high temperatures. Proc. of 7 th Int. Symp. on Ballistics. The Netherlands, pp
FINITE ELEMENT MODELING OF THICK PLATE PENETRATIONS IN SMALL CAL MUNITIONS
FINITE ELEMENT MODELING OF THICK PLATE PENETRATIONS IN SMALL CAL MUNITIONS Raymond Chaplin RDAR-MEM-I Picatinny Arsenal, NJ raymond.c.chaplin@us.army.mil 973-724-8562 Why Finite Element Modeling? Reduced
More informationA METHOD TO INCREASE THE TIP VELOCITY OF A SHAPED CHARGE JET. William P. Walters and Daniel R. Scheffler
23 RD INTERNATIONAL SYMPOSIUM ON BALLISTICS TARRAGONA, SPAIN 16-20 APRIL 2007 A METHOD TO INCREASE THE TIP VELOCITY OF A SHAPED CHARGE JET William P. Walters and Daniel R. Scheffler US Army Research Laboratory,
More informationModelling of Impact on a Fuel Tank Using Smoothed Particle Hydrodynamics
Modelling of Impact on a Fuel Tank Using Smoothed Particle Hydrodynamics R. Vignjevic a, T. De Vuyst a, J. Campbell a, N. Bourne b School of Engineering, Cranfield University, Bedfordshire, MK43 0AL, UK.
More informationEffect of Soil Material Models on SPH Simulations for Soil- Structure Interaction
Effect of Soil Material Models on SPH Simulations for Soil- Structure Interaction Ronald F. Kulak 1 Len Schwer 2 1) RFK Engineering Mechanics Consultants 307 Warwick Drive Naperville, IL 60565, USA rfkemc@aol.com
More informationPredictions of projectile penetration and perforation by DAFL with the free surface effect
Structures Under Shock and Impact XII 49 Predictions of projectile penetration and perforation by DAFL with the free surface effect Q. Fang, X. Kong, H. Wu & H. Yan Engineering Institute of Engineering
More informationImpact Simulations on Concrete Slabs : LS-OPT Fitting Approach
Impact Simulations on Concrete Slabs : LS-OPT Fitting Approach Nicolas VAN DORSSELAER (1), Vincent LAPOUJADE (1), Georges NAHAS (2), François TARALLO (2), Jean-Mathieu RAMBACH (2) (1) Alliance Services
More informationSIMULATION OF A DETONATION CHAMBER TEST CASE
SIMULATION OF A DETONATION CHAMBER TEST CASE Daniel Hilding Engineering Research Nordic AB Garnisonen I4, Byggnad 5 SE-582 10 Linköping www.erab.se daniel.hilding@erab.se Abstract The purpose of a detonation
More informationSimulation of engraving process of large-caliber artillery using coupled Eulerian-Lagrangian method
Simulation of engraving process of large-caliber artillery using coupled Eulerian-Lagrangian method Zhen Li 1, Jianli Ge 2, Guolai Yang 3, Jun Tang 4 School of Mechanical Engineering, Nanjing University
More informationEXPERIMENTAL VALIDATION OF TURNING PROCESS USING 3D FINITE ELEMENT SIMULATIONS
CHAPTER-5 EXPERIMENTAL VALIDATION OF TURNING PROCESS USING 3D FINITE ELEMENT SIMULATIONS This chapter presents the three-dimensional (3D) finite element analysis (FEA) to calculate the workpiece tool wear
More information2008 International ANSYS Conference Simulation of Densification in Granular Materials and Geomaterials
2008 International ANSYS Conference Simulation of Densification in Granular Materials and Geomaterials Lewis Hartless, PE Principal Engineer Babcock & Wilcox lchartless@babcock.com 1 Overview An implicit
More informationLS-Dyna CAE A ssociates Associates
LS-Dyna at CAE Associates Overview Experience with LS-Dyna for Dynamics Modeling CAE Associates engineers have nearly 30 years of experience using explicit dynamics finite element codes for complex design
More informationSimulating Reinforced Concrete Beam-Column Against Close-In Detonation using S-ALE Solver
Simulating Reinforced Concrete Beam-Column Against Close-In Detonation using S-ALE Solver Shih Kwang Tay, Roger Chan and Jiing Koon Poon Ministry of Home Affairs, Singapore 1 Abstract A 3-stage loading
More informationAn Efficient Sequential Approach for Simulation of Thermal Stresses in Disc Brakes
An Efficient Sequential Approach for Simulation of Thermal Stresses in Disc Brakes Asim Rashid 1, Niclas Strömberg 1 1 Jönköping University, SE-55111 Jönköping, Sweden Abstract In this paper an efficient
More informationOrbital forming of SKF's hub bearing units
Orbital forming of SKF's hub bearing units Edin Omerspahic 1, Johan Facht 1, Anders Bernhardsson 2 1 Manufacturing Development Centre, AB SKF 2 DYNAmore Nordic 1 Background Orbital forming is an incremental
More informationOn the SPH Orthogonal Cutting Simulation of A2024-T351 Alloy
Available online at www.sciencedirect.com Procedia CIRP 8 (2013 ) 152 157 14 th CIRP Conference on Modeling of Machining Operations (CIRP CMMO) On the SPH Orthogonal Cutting Simulation of A2024-T351 Alloy
More informationLimitations of smeared crack models for dynamic analysis of concrete
12 th International LS-DYNA Users Conference Constitutive Modeling(3) Limitations of smeared crack models for dynamic analysis of concrete Yoeng Sin Khoe and Jaap Weerheijm TNO PO Box 4, 2280AA Rijswijk
More informationExample 13 - Shock Tube
Example 13 - Shock Tube Summary This famous experiment is interesting for observing the shock-wave propagation. Moreover, this case uses the representation of perfect gas and compares the different formulations:
More informationExplicit Dynamic Analysis of Bird Strike Simulations and Design Optimization of Composite Aircraft Structures
Explicit Dynamic Analysis of Bird Strike Simulations and Design Optimization of Composite Aircraft Structures Manoj Susarla Jr Design Engineer Octants Engineering Innovations Dr no 12-3-25,Ayyevari street,
More informationCOMPUTATIONAL SIMULATION OF BLAST LOADING IN AN OPEN CYLINDER MODEL USING ANSYS AND LS-DYNA
COMPUTATIONAL SIMULATION OF BLAST LOADING IN AN OPEN CYLINDER MODEL USING ANSYS AND LS-DYNA Ramprashad Prabhakaran Graduate Student Department of Mechanical Engineering University of Nevada, Las Vegas
More informationNUMERICAL SIMULATION OF STRUCTURAL DEFORMATION UNDER SHOCK AND IMPACT LOADS USING A COUPLED MULTI-SOLVER APPROACH
NUMERICAL SIMULATION OF STRUCTURAL DEFORMATION UNDER SHOCK AND IMPACT LOADS USING A COUPLED MULTI-SOLVER APPROACH X. Quan, N. K. Birnbaum, M.S. Cowler, B. I. Gerber Century Dynamics, Inc., 1001 Galaxy
More informationReinforced concrete beam under static load: simulation of an experimental test
Reinforced concrete beam under static load: simulation of an experimental test analys: nonlin physic. constr: suppor. elemen: bar cl12i cl3cm compos cq16m interf pstres reinfo struct. load: deform weight.
More informationContents Metal Forming and Machining Processes Review of Stress, Linear Strain and Elastic Stress-Strain Relations 3 Classical Theory of Plasticity
Contents 1 Metal Forming and Machining Processes... 1 1.1 Introduction.. 1 1.2 Metal Forming...... 2 1.2.1 Bulk Metal Forming.... 2 1.2.2 Sheet Metal Forming Processes... 17 1.3 Machining.. 23 1.3.1 Turning......
More informationCurvilinear trajectory and smart fuze calculations suitable for hard target defeat modeling
Weapons Curvilinear trajectory and smart fuze calculations suitable for hard target defeat modeling 5 nd Annual Fuze Conference Sparks, NV, USA, 13-15 15 May 8 Centre d Etudes de Gramat BP 8 F-465 GRAMAT
More informationA MODELING METHOD OF CURING DEFORMATION FOR CFRP COMPOSITE STIFFENED PANEL WANG Yang 1, GAO Jubin 1 BO Ma 1 LIU Chuanjun 1
21 st International Conference on Composite Materials Xi an, 20-25 th August 2017 A MODELING METHOD OF CURING DEFORMATION FOR CFRP COMPOSITE STIFFENED PANEL WANG Yang 1, GAO Jubin 1 BO Ma 1 LIU Chuanjun
More informationFinite Element Simulation using SPH Particles as Loading on Typical Light Armoured Vehicles
10 th International LS-DYNA Users Conference Penetration / Blast Finite Element Simulation using SPH Particles as Loading on Typical Light Armoured Vehicles Geneviève Toussaint and Robert Durocher Defence
More informationA New Way for Multi-piece and Multi-hit Fragment Impact Simulation Using LS-DYNA
9 th International LS-DYNA Users Conference Impact Analysis (1) A New Way for Multi-piece and Multi-hit Fragment Impact Simulation Using LS-DYNA Xudong Xin Karagozian and Case 255 N. Hollywood Way, Suite
More informationAvailable online at ScienceDirect. Procedia Engineering 150 (2016 )
Available online at www.sciencedirect.com ScienceDirect Procedia Engineering 150 (2016 ) 866 870 International Conference on Industrial Engineering, ICIE 2016 Numerical Simulation of the Aluminum 6061-T6
More informationFFI RAPPORT EXAMINATION OF YAWED IMPACT USING A COMBINED NUMERICAL AND ANALYTICAL APPROACH. TELAND Jan Arild FFI/RAPPORT-2003/00935
FFI RAPPORT EXAMINATION OF YAWED IMPACT USING A COMBINED NUMERICAL AND ANALYTICAL APPROACH TELAND Jan Arild FFI/RAPPORT-2003/00935 FFIBM/766/130 Approved Kjeller 4. March 2003 Bjarne Haugstad Director
More informationNumerical Modelling of Cross Roll Straightening
7. LS-DYNA Anwenderforum, Bamberg 2008 Metallumformung I Numerical Modelling of Cross Roll Straightening A. Mutrux, B. Berisha, B. Hochholdinger, P. Hora Institute of Virtual Manufacturing, ETH Zurich
More informationGALAXY ADVANCED ENGINEERING, INC. P.O. BOX 614 BURLINGAME, CALIFORNIA Tel: (650) Fax: (650)
GALAXY ADVANCED ENGINEERING, INC. P.O. BOX 614 BURLINGAME, CALIFORNIA 94011 Tel: (650) 740-3244 Fax: (650) 347-4234 E-mail: bahmanz@aol.com PUFF-TFT/PC A Material Response Computer Code for PC Computer
More informationExample 24 Spring-back
Example 24 Spring-back Summary The spring-back simulation of sheet metal bent into a hat-shape is studied. The problem is one of the famous tests from the Numisheet 93. As spring-back is generally a quasi-static
More informationCoupled numerical-experimental study of an armour perforation by the armour-piercing projectiles
Computational Methods and Experimental Measurements XV 615 Coupled numerical-experimental study of an armour perforation by the armour-piercing projectiles B. Zduniak, A. Morka & T. Niezgoda Department
More informationSimilar Pulley Wheel Description J.E. Akin, Rice University
Similar Pulley Wheel Description J.E. Akin, Rice University The SolidWorks simulation tutorial on the analysis of an assembly suggested noting another type of boundary condition that is not illustrated
More informationSimulating Underbelly Blast Events using Abaqus/Explicit - CEL
U.S. Army Research, Development and Engineering Command Simulating Underbelly Blast Events using Abaqus/Explicit - CEL J. Jablonski, P. Carlucci (U.S. Army ARDEC) R. Thyagarajan (U.S. Army TARDEC) B. Nandi,
More informationCHAPTER 6 EXPERIMENTAL AND FINITE ELEMENT SIMULATION STUDIES OF SUPERPLASTIC BOX FORMING
113 CHAPTER 6 EXPERIMENTAL AND FINITE ELEMENT SIMULATION STUDIES OF SUPERPLASTIC BOX FORMING 6.1 INTRODUCTION Superplastic properties are exhibited only under a narrow range of strain rates. Hence, it
More informationSet No. 1 IV B.Tech. I Semester Regular Examinations, November 2010 FINITE ELEMENT METHODS (Mechanical Engineering) Time: 3 Hours Max Marks: 80 Answer any FIVE Questions All Questions carry equal marks
More informationFinal project: Design problem
ME309 Homework #5 Final project: Design problem Select one of the analysis problems listed below to solve. Your solution, along with a description of your analysis process, should be handed in as a final
More informationDevelopment of smart and flexible freight wagons and facilities for improved transport of granular multimaterials
Development of smart and flexible freight wagons and facilities for improved transport of granular multimaterials Deliverable D4.2 Validation of models The project Development of smart and flexible freight
More informationSECTION ANALYSIS PROGRAM RESPONSE 2000
SECTION ANALYSIS PROGRAM RESPONSE 2000 DESCRIPTION Response-2000 is a user friendly sectional analysis program that can be used to predict the complete load-deformation response of a reinforced or prestressed
More informationModeling Methodologies for Assessment of Aircraft Impact Damage to the World Trade Center Towers
9 th International LS-DYNA Users Conference Modeling Methodologies for Assessment of Aircraft Impact Damage to the World Trade Center Towers S.W. Kirkpatrick, R.T. Bocchieri, R.A. MacNeill, and B.D. Peterson
More informationES 128: Computer Assignment #4. Due in class on Monday, 12 April 2010
ES 128: Computer Assignment #4 Due in class on Monday, 12 April 2010 Task 1. Study an elastic-plastic indentation problem. This problem combines plasticity with contact mechanics and has many rich aspects.
More informationLinear Elastic Fracture Mechanics (LEFM) Analysis of Flaws within Residual Stress Fields
Linear Elastic Fracture Mechanics (LEFM) Analysis of Flaws within Residual Stress Fields David Woyak 1, Brian Baillargeon, Ramesh Marrey, and Randy Grishaber 2 1 Dassault Systemés SIMULIA Corporation &
More informationInfluence of geometric imperfections on tapered roller bearings life and performance
Influence of geometric imperfections on tapered roller bearings life and performance Rodríguez R a, Calvo S a, Nadal I b and Santo Domingo S c a Computational Simulation Centre, Instituto Tecnológico de
More informationChapter 1 Introduction
Chapter 1 Introduction GTU Paper Analysis (New Syllabus) Sr. No. Questions 26/10/16 11/05/16 09/05/16 08/12/15 Theory 1. What is graphic standard? Explain different CAD standards. 2. Write Bresenham s
More informationCOMPUTATIONAL AND EXPERIMENTAL MECHANICS RESEARCH GROUP
COMPUTATIONAL AND EXPERIMENTAL MECHANICS RESEARCH GROUP The University of Texas at El Paso PURPOSE The Computational and Experimental Mechanics Research Group at the University of Texas at El Paso (UTEP)
More informationTHREE-DIMENSIONAL ANALYSIS OF THE EXPLOSIVE INITIATION THRESHOLD FOR SIDE IMPACT ON A SHAPED CHARGE WARHEAD
Insensitive Munitions and Energetics Technology Symposium Tampa, Florida, USA, October 1997 THREE-DIMENSIONAL ANALYSIS OF THE EXPLOSIVE INITIATION THRESHOLD FOR SIDE IMPACT ON A SHAPED CHARGE WARHEAD David
More informationAnalysis of ANSI W W 6x9-118,
Page 1 of 8 Analysis of ANSI W W 6x9-118,110236220472 Author: Analysis Created: Analysis Last Modified: Report Created: Introduction Administrator, 08:29:09, 08:29:09 09:26:02 Database: Z:\ENGENHARIA\ESTUDOS
More informationNumerical Simulation of Near-Field Explosion
Journal of Applied Science and Engineering, Vol. 16, No. 1, pp. 61 67 (2013) 61 Numerical Simulation of Near-Field Explosion Ding-Shing Cheng 1, Cheng-Wei Hung 2 and Sheng-Jung Pi 2 * 1 Department of Environmental
More informationRecent Advances on Higher Order 27-node Hexahedral Element in LS-DYNA
14 th International LS-DYNA Users Conference Session: Simulation Recent Advances on Higher Order 27-node Hexahedral Element in LS-DYNA Hailong Teng Livermore Software Technology Corp. Abstract This paper
More informationGRID PATTERN EFFECTS ON AERODYNAMIC CHARACTERISTICS OF GRID FINS
24 TH INTERNATIONAL CONGRESS OF THE AERONAUTICAL SCIENCES GRID PATTERN EFFECTS ON AERODYNAMIC CHARACTERISTICS OF GRID FINS Fumiya Hiroshima, Kaoru Tatsumi* *Mitsubishi Electric Corporation, Kamakura Works,
More informationEmbedded Reinforcements
Embedded Reinforcements Gerd-Jan Schreppers, January 2015 Abstract: This paper explains the concept and application of embedded reinforcements in DIANA. Basic assumptions and definitions, the pre-processing
More informationAdvanced Material Models and Geomechanics
Advanced Material Models and Geomechanics Giovanni Federico, Mark Robinson ANSYS UK Ltd 1 2016 ANSYS, Inc. April 28, 2017 2 2016 ANSYS, Inc. April 28, 2017 Advanced Material Models NEW Unified Viscoplasticity
More informationModeling Fluid-Structure Interaction in Cavitation Erosion using Smoothed Particle Hydrodynamics
Modeling Fluid-Structure Interaction in Cavitation Erosion using Smoothed Particle Hydrodynamics Introduction Shrey Joshi 1,2, Jean Pierre Franc 2, Giovanni Ghigliotti 2, Marc Fivel 1 1 Univ Grenoble Alpes,
More informationLateral Loading of Suction Pile in 3D
Lateral Loading of Suction Pile in 3D Buoy Chain Sea Bed Suction Pile Integrated Solver Optimized for the next generation 64-bit platform Finite Element Solutions for Geotechnical Engineering 00 Overview
More informationANSYS AIM Tutorial Structural Analysis of a Plate with Hole
ANSYS AIM Tutorial Structural Analysis of a Plate with Hole Author(s): Sebastian Vecchi, ANSYS Created using ANSYS AIM 18.1 Problem Specification Pre-Analysis & Start Up Analytical vs. Numerical Approaches
More informationALE Modeling of Explosive Detonation on or near Reinforced-Concrete Columns
12 th International LS-DYNA Users Conference FSI/ALE(1) ALE Modeling of Explosive Detonation on or near Reinforced-Concrete Columns John M. H. Puryear Protection Engineering Consultants, 14144 Trautwein
More informationApplications of ICFD /SPH Solvers by LS-DYNA to Solve Water Splashing Impact to Automobile Body. Abstract
Applications of ICFD /SPH Solvers by LS-DYNA to Solve Water Splashing Impact to Automobile Body George Wang (1 ), Kevin Gardner (3), Eric DeHoff (1), Facundo del Pin (2), Inaki Caldichoury (2), Edouard
More informationON THE VELOCITY OF A WEIGHTED CYLINDER DOWN AN INCLINED PLANE
ON THE VELOCITY OF A WEIGHTED CYLINDER DOWN AN INCLINED PLANE Raghav Grover and Aneesh Agarwal RG (Grade 12 High School), AA (Grade 11 High School) Department of Physics, The Doon School, Dehradun. raghav.503.2019@doonschool.com,
More informationIdentification of strain-rate sensitivity parameters of steel sheet by genetic algorithm optimisation
High Performance Structures and Materials III Identification of strain-rate sensitivity parameters of steel sheet by genetic algorithm optimisation G. Belingardi, G. Chiandussi & A. Ibba Dipartimento di
More informationENHANCED FRAGMENTATION MODELING
ENHANCED FRAGMENTATION MODELING Peter Rottinger*, Richard Fong, William Ng U.S. ARMY ARDEC Picatinny Arsenal, NJ, 07806 ABSTRACT Enhancing the fragmentation capability of current and future projectiles
More informationFinite Element Modal Analysis and Mesh Optimization of a Typical Turbo Fan Engine Fan Hub Frame
Finite Element Modal Analysis and Mesh Optimization of a Typical Turbo Fan Engine Fan Hub Frame Charles.G.Martin 1 and Dr. A. Arokkiaswamy 2 1,2 Department of Aeronautical Engg, DSCE, Shavige Malleshwara
More informationDevelopment of a Soft Recovery System of Supersonic Projectiles
ENGINEERING TRANSACTIONS Engng. Trans. 60, 1, 3 14, 2012 Polish Academy of Sciences Institute of Fundamental Technological Research(IPPT PAN) National Engineering School of Metz(ENIM) SIXTY YEARS OF THE
More informationQualification of *Constrained_Lagrange_In_Solid command for steel/concrete interface modeling
Qualification of *Constrained_Lagrange_In_Solid command for steel/concrete interface modeling L. MOUTOUSSAMY 1,2, G. HERVE 1, F. BARBIER 1 1 Tractebel Engineering France, 2 University Pierre and Marie
More informationOptimization and Simulation of Machining Parameters in Radial-axial Ring Rolling Process
International Journal of Computational Intelligence Systems, Vol.4, No. 3 (May, 0). Optimization and Simulation of Machining Parameters in Radial-axial Ring Rolling Process Shuiyuan Tang, Jiping Lu *,
More informationSIMULATION AND ANALYSIS OF CHIP BREAKAGE IN TURNING PROCESSES
SIMULATION AND ANALYSIS OF CHIP BREAKAGE IN TURNING PROCESSES Troy D. Marusich, Jeffrey D. Thiele and Christopher J. Brand 1 INTRODUCTION In order to improve metal cutting processes, i.e. lower part cost,
More informationDEVELOPMENT OF A NUMERICAL MODEL FOR SIMULATIONS OF SPLIT HOPKINSON PRESSURE BAR
DEVELOPMENT OF A NUMERICAL MODEL FOR SIMULATIONS OF SPLIT HOPKINSON PRESSURE BAR Afdhal 1, Annisa Jusuf 1, Muhammad Agus Kariem 2 and Leonardo Gunawan 1 1 Lightweight Structures Research Group, Faculty
More informationSimulations of tunnel excavation in 2D and 3D conditions considering building loads
Simulations of tunnel excavation in D and 3D conditions considering building loads T. Nakai, E. Sung, H.M. Shahin & M. Yamamoto Nagoya Institute of Technology, Nagoya, Japan ABSTRACT: Two-dimensional model
More informationFinite Element Course ANSYS Mechanical Tutorial Tutorial 4 Plate With a Hole
Problem Specification Finite Element Course ANSYS Mechanical Tutorial Tutorial 4 Plate With a Hole Consider the classic example of a circular hole in a rectangular plate of constant thickness. The plate
More informationTHE COMPUTATIONAL MODEL INFLUENCE ON THE NUMERICAL SIMULATION ACCURACY FOR FORMING ALLOY EN AW 5754
THE COMPUTATIONAL MODEL INFLUENCE ON THE NUMERICAL SIMULATION ACCURACY FOR FORMING ALLOY EN AW 5754 Pavel SOLFRONK a, Jiří SOBOTKA a, Pavel DOUBEK a, Lukáš ZUZÁNEK a a TECHNICAL UNIVERSITY OF LIBEREC,
More informationME Optimization of a Frame
ME 475 - Optimization of a Frame Analysis Problem Statement: The following problem will be analyzed using Abaqus. 4 7 7 5,000 N 5,000 N 0,000 N 6 6 4 3 5 5 4 4 3 3 Figure. Full frame geometry and loading
More informationSmoothed Particle Galerkin Method with a Momentum-Consistent Smoothing Algorithm for Coupled Thermal-Structural Analysis
Smoothed Particle Galerkin Method with a Momentum-Consistent Smoothing Algorithm for Coupled Thermal-Structural Analysis X. Pan 1*, C.T. Wu 1, W. Hu 1, Y.C. Wu 1 1Livermore Software Technology Corporation
More informationSome Aspects for the Simulation of a Non-Linear Problem with Plasticity and Contact
Some Aspects for the Simulation of a Non-Linear Problem with Plasticity and Contact Eduardo Luís Gaertner Marcos Giovani Dropa de Bortoli EMBRACO S.A. Abstract A linear elastic model is often not appropriate
More informationTABLE OF CONTENTS SECTION 2 BACKGROUND AND LITERATURE REVIEW... 3 SECTION 3 WAVE REFLECTION AND TRANSMISSION IN RODS Introduction...
TABLE OF CONTENTS SECTION 1 INTRODUCTION... 1 1.1 Introduction... 1 1.2 Objectives... 1 1.3 Report organization... 2 SECTION 2 BACKGROUND AND LITERATURE REVIEW... 3 2.1 Introduction... 3 2.2 Wave propagation
More informationA Computational Analysis of a Shear Punch Test
A Computational Analysis of a Shear Punch Test by Stephan R. Bilyk ARL-RP-263 August 2009 A reprint from the Proceedings of the JANNAF Conference, Colorado Springs, CO, 1 5 December 2003. Approved for
More informationFinite Element Model for Axial Stiffness of Metal-Plate-Connected Tension Splice Wood Truss Joint
Finite Element Model for Axial Stiffness of Metal-Plate-Connected Tension Splice Wood Truss Joint Jose M. Cabrero Assistant Professor University of Navarra, Department of Structural Analysis and Design,
More informationSERBIATRIB 15 STATIC PERFORMANCE OF SURFACE TEXTURED MAGNETORHEOLOGICAL FLUID JOURNAL BEARINGS. 14 th International Conference on Tribology
Serbian Tribology Society SERBIATRIB 15 14 th International Conference on Tribology Belgrade, Serbia, 13 15 May 015 University of Belgrade, Faculty of Mechanical Engineering STATIC PERFORMANCE OF SURFACE
More informationUsing three-dimensional CURVIC contact models to predict stress concentration effects in an axisymmetric model
Boundary Elements XXVII 245 Using three-dimensional CURVIC contact models to predict stress concentration effects in an axisymmetric model J. J. Rencis & S. R. Pisani Department of Mechanical Engineering,
More informationGood Practice Guide to the Application of Finite Element Analysis to Erosion Modelling
Good Practice Guide No. 146 Good Practice Guide to the Application of Finite Element Analysis to Erosion Modelling EXPERT TECHNICAL LEVEL Good Practice Guide No. 146 Version 1.0 Published in the United
More informationModeling blast loading on buried reinforced concrete structures with Zapotec
Shock and Vibration 15 (2008) 137 146 137 IOS Press Modeling blast loading on buried reinforced concrete structures with Zapotec Greg C. Bessette Sandia National Laboratories, P.O. Box 5800, Albuquerque,
More informationWeight And Reliability Optimization Of A Helicopter Composite Armor Using Dynamic Programming
Copyright c 2007 ICCES ICCES, vol.4, no.2, pp.53-58, 2007 Weight And Reliability Optimization Of A Helicopter Composite Armor Using Dynamic Programming V.C. Santos 1,P.S.Lopes 1,R.Gärtner 2 and A.B. Jorge
More informationStress Analysis of Cross Groove Type Constant Velocity Joint
TECHNICAL REPORT Stress Analysis of Cross Groove Type Constant Velocity Joint H. SAITO T. MAEDA The driveshaft is the part that transmits the vehicle's engine torque and rotation to the tires, and predicting
More informationCOMPUTATIONALLY EFFICIENT RAY TRACING ALGORITHM FOR SIMULATION OF TRANSDUCER FIELDS IN ANISOTROPIC MATERIALS
Proceedings of the National Seminar & Exhibition on Non-Destructive Evaluation NDE 2011, December 8-10, 2011 COMPUTATIONALLY EFFICIENT RAY TRACING ALGORITHM FOR SIMULATION OF TRANSDUCER FIELDS IN ANISOTROPIC
More informationA Sensitivity Analysis On The Springback Behavior Of The Unconstrained Bending Problem
A Sensitivity Analysis On The Springback Behavior Of The Unconstrained Bending Problem T. Meinders 1,2, A.W.A. Konter 1, S.E. Meijers 1, E.H. Atzema 3, H. Kappert 4 1 Netherlands Institute for Metals Research,
More informationCHAPTER-10 DYNAMIC SIMULATION USING LS-DYNA
DYNAMIC SIMULATION USING LS-DYNA CHAPTER-10 10.1 Introduction In the past few decades, the Finite Element Method (FEM) has been developed into a key indispensable technology in the modeling and simulation
More informationModelling Flat Spring Performance Using FEA
Modelling Flat Spring Performance Using FEA Blessing O Fatola, Patrick Keogh and Ben Hicks Department of Mechanical Engineering, University of Corresponding author bf223@bath.ac.uk Abstract. This paper
More informationThe Effect of Mesh Sizing Toward Deformation Result in Computational Dynamic Simulation for Blast Loading Application
Modern Applied Science; Vol. 7, No. 7; 2013 ISSN 1913-1844 E-ISSN 1913-1852 Published by Canadian Center of Science and Education The Effect of Mesh Sizing Toward Deformation Result in Computational Dynamic
More informationChapter 20. Finite Element Method (FEM) Introduction
Chapter 20. Finite Element Method (FEM) Introduction The objective of this chapter is to explain basic terms of the particular field of problems and practical application of GEO 5 FEM program to solve
More informationInfluence of mesh quality and density on numerical calculation of heat exchanger with undulation in herringbone pattern
Influence of mesh quality and density on numerical calculation of heat exchanger with undulation in herringbone pattern Václav Dvořák, Jan Novosád Abstract Research of devices for heat recovery is currently
More informationSimulation of Fuel Sloshing Comparative Study
3. LS-DYNA Anwenderforum, Bamberg 2004 Netfreie Verfahren Simulation of Fuel Sloshing Comparative Study Matej Vesenjak 1, Heiner Müllerschön 2, Alexander Hummel 3, Zoran Ren 1 1 University of Maribor,
More informationHigh performance computing using AUTODYN-3D
High performance computing using AUTODYN-3D M. S. Cowler', O. La'adan\ T. Ohta^ ' Century Dynamics Incorporated, USA. Hebrew University ofjerusalem, Israel. * CRC Research Institute Incorporated, Japan.
More informationCTH: A Software Family for Multi-Dimensional Shock Physics Analysis E. S. Hertel, Jr., R. L. Bell, M. G. Elrick, A. V. Farnsworth, G. I. Kerley, J.
CTH: A Software Family for Multi-Dimensional Shock Physics Analysis E. S. Hertel, Jr., R. L. Bell, M. G. Elrick, A. V. Farnsworth, G. I. Kerley, J. M. McGlaun, S. V. Petney, S. A. Silling, P. A. Taylor,
More informationPile Test Finite Element Analyses
Pile Test Finite Element Analyses Stéphane Commend*, Philippe Menétrey** * GeoMod ingénieurs conseils SA, Lausanne, Switzerland ** INGPHI SA ingénieurs en ouvrage d art, Lausanne, Switzerland Keywords:
More informationturning and milling Phone Fax ABSTRACT:
Cowper-Symonds material deformation law application in material cutting process using LS-DYNA FE code: turning and milling Virginija Gyliene Vytautas Ostasevicius Department of Engineering Design Faculty
More information14 Dec 94. Hydrocode Micro-Model Concept for Multi-Component Flow in Sediments Hans U. Mair
Hydrocode Micro-Model Concept for Multi-Component Flow in Sediments Hans U. Mair mairh@asme.org Background Hydrocodes are Computational Mechanics tools that simulate the compressible dynamics (i.e., shock
More informationModeling Rebar in Reinforced Concrete for ALE Simulations
14 th International LS-DYNA Users Conference Session: Constitutive Modeling Modeling Rebar in Reinforced Concrete for ALE Simulations Shih Kwang TAY, Jiing Koon POON and Roger CHAN Ministry of Home Affairs,
More informationAn Explanation on Computation of Fracture Mechanics Parameters in ANSYS
University of Tennessee Space Institute Department of Mechanical, Aerospace & Biomedical Engineering Fracture Mechanics Course (ME 524) An Explanation on Computation of Fracture Mechanics Parameters in
More informationEXACT BUCKLING SOLUTION OF COMPOSITE WEB/FLANGE ASSEMBLY
EXACT BUCKLING SOLUTION OF COMPOSITE WEB/FLANGE ASSEMBLY J. Sauvé 1*, M. Dubé 1, F. Dervault 2, G. Corriveau 2 1 Ecole de technologie superieure, Montreal, Canada 2 Airframe stress, Advanced Structures,
More informationFully-Coupled Thermo-Mechanical Analysis
Fully-Coupled Thermo-Mechanical Analysis Type of solver: ABAQUS CAE/Standard Adapted from: ABAQUS Example Problems Manual Extrusion of a Cylindrical Aluminium Bar with Frictional Heat Generation Problem
More information1. The program has automatic generation of technical reports using customized Word templates as *.dotx-files.
SOFTWARE FOR SIMULATION AND OPTIMIZATION OF METAL FORMING PROCESSES AND PROFILE EXTRUSION QForm VX 8.2.3 new facilities and features October 2017 The new version of QForm has some amazing new features,
More informationApplication of Finite Volume Method for Structural Analysis
Application of Finite Volume Method for Structural Analysis Saeed-Reza Sabbagh-Yazdi and Milad Bayatlou Associate Professor, Civil Engineering Department of KNToosi University of Technology, PostGraduate
More information