Determination of turbine runner dynamic behaviour under operating condition by a two-way staggered fluid-structureinteraction method
|
|
- Gregory Briggs
- 6 years ago
- Views:
Transcription
1 IOP Conference Series: Earth and Environmental Science Determination of turbine runner dynamic behaviour under operating condition by a two-way staggered fluid-structureinteraction method To cite this article: F Dompierre and M Sabourin 2010 IOP Conf. Ser.: Earth Environ. Sci Related content - Influence of the rotor-stator interaction on the dynamic stresses of Francis runners R Guillaume, J L Deniau, D Scolaro et al. - Challenges in Dynamic Pressure and Stress Predictions at No-Load Operation in Hydraulic Turbines B Nennemann, J F Morissette, J Chamberland-Lauzon et al. - Evaluation of RSI-induced stresses in Francis runners U Seidel, B Hübner, J Löfflad et al. View the article online for updates and enhancements. This content was downloaded from IP address on 29/04/2018 at 06:48
2 Determination of turbine runner dynamic behaviour under operating condition by a two-way staggered fluid-structure interaction method 1. Introduction F Dompierre 1 and M Sabourin 1 1 Alstom Power Systems, Hydro 1350 chemin Saint-Roch, Sorel-Tracy (Québec), Canada, J3R 5P9 frederick.dompierre@power.alstom.com Abstract. This paper presents the application of the two-way fluid-structure interaction method introduced by ANSYS to calculate the dynamic behaviour of a Francis turbine runner under operating condition. This time-dependant calculation directly takes into account characteristics of the flow and particularly the pressure fluctuations caused by the rotor-stator interaction. This formulation allows the calculation of the damping forces of the whole system implicitly. Thereafter, the calculated dynamic stress can be used for a fatigue analysis. A verification of the mechanical and fluid simulations used as input for the fluid-structure interaction calculation is first performed. Subsequently, a connection of these two independent simulations is made. A validation according to the hydraulic conditions is made with the measurements from the scale model testing. Afterwards, the static displacement of the runner under the hydraulic load is compared with the results of a classical static analysis for verification purposes. Finally, the natural frequencies deduced by the post-processing of the dynamic portion of the runner displacement with respect to time are compared with the natural frequencies obtained from a classical acoustic modal analysis. All comparisons show a good agreement with experimental data or results obtained with conventional methods. The failure of hydraulic turbine components under operating condition may cause important losses of production for hydroelectric plant owners. The runner, which is responsible of the conversion of hydraulic energy into mechanical energy, is the most vulnerable component since it is exposed to many sources of dynamic excitation. To avoid its failure, it is therefore of a great importance to predict its dynamic behaviour at the design stage. However, this prediction is not simple because of the system's complexity, which includes the runner itself and the flow passing through it. The fluid-structure interaction (FSI) involved presents a strong coupling. A decade ago, acoustic modal analysis has emerged to allow the prediction of the natural frequencies of turbine runners in still water [1, 2, 3]. Because the excitation frequencies are relatively well known, this method allows to establish if a frequency match exists between a structural vibration mode and a given hydraulic excitation. More recently, harmonic acoustic analysis has been used to quantify the dynamic response of turbine runner taking into account the geometric compatibility between fluid excitation calculated by Computational Fluid Dynamics (CFD) and a single mode calculated in still water [4], [5]. Nevertheless, a parameter of major influence in the vicinity of the resonance remains unknown, namely the damping force contribution. Indeed, the damping factor in still water is usually much lower than when the flow is taken into account [6]. It also depends strongly on the vibration mode considered. For a harmonic acoustic analysis, the damping factor is an input that must be determined empirically. This paper presents the application of the two-way FSI method introduced by ANSYS to predict the dynamic behaviour of a Francis turbine runner under normal operating condition. This method allows the calculation of the runner dynamic response with respect to time taking into account all the characteristics of the flow such as the fluid viscosity and turbulence. The damping contribution is then calculated implicitly. This method has been validated for simple academic test cases of free vibration in still water [7]. c 2010 Ltd 1
3 2. Francis Turbine Analysis The simulated case presented in this paper corresponds to a Francis turbine at industrial scale having 15 runner blades and 20 guide vanes. This particular configuration allows the modeling of one 5 th of the system and the reduction of the mesh size by the use of cyclic symmetry conditions. The distributor is approximated as being axisymmetric and the model includes only the draft tube cone. The computational domain is shown in Fig. 1. Fig. 1 Geometry of the domain used for the Francis turbine simulation Some simplifications have been made to the turbine geometry to facilitate the calculation. First, the balancing pipes have been replaced by balancing holes. Secondly, labyrinth seal clearances have been tripled to avoid excessive local mesh resolution. The computation by the two-way FSI method is made by the union of a classical mechanical simulation and a classical CFD simulation. To ensure proper behaviour of the FSI simulation, each basic simulation must be verified independently before their coupling. 3. Mechanical Simulation The mesh of the mechanical simulation is made of tetrahedral quadratic elements. The resolution is about nodes for one 5 th of the runner. This mesh is presented in Fig. 2. Table 1 Mechanical analysis parameters Parameters Units Time step (s) 2.5 * 10-4 Rotational Speed (RPM) 300 Gravitational (m/s 2 ) 9.81 Acceleration Solver type - Direct Non-linear method - Newton- Raphson Fig. 2 Solid mesh corresponding to one 5 th of the Francis turbine runner 2
4 A static analysis of the runner made at the runaway speed has been compared with a similar analysis for a complete runner. The calculated displacements were compared to check the convergence and the consistency of the model including cyclic symmetry conditions. From the verified static analysis, a time-dependant analysis is built. Since this simulation is used as an input to the simulation including FSI, all surfaces in contact with water are flagged to allow the imposition of pressure fields which will come from the CFD calculation. No structural damping is imposed since the damping contribution of fluid flow is assumed to be much higher. The mechanical analysis parameters are summarized in Table CFD Simulation The turbine operating point used for the calculation has been chosen to maximize the rotor-stator interaction (RSI) intensity. The guide vanes opening angle is then set to maximum in order to reduce the gap between the guide vanes outlet and the runner blade inlet. The meshes used for the static and the rotating parts of the fluid simulation are of unstructured tetrahedral type. An inflate of prismatic elements is applied on all solid walls of the runner. The resolution of the fluid meshes is summarized in Table 2. A cross section of the meshes at the distributor axis elevation is shown in Fig. 3. Table 2 Resolution of the CFD meshes Domain Resolution (Nodes) Distributor Runner Fig. 3 Fluid mesh section of the turbine at the distributor axis elevation As boundary conditions, the flow angle at the inlet section is set to ensure the flow alignment with the stay vanes. A total pressure condition with an average turbulence intensity of 5% and a length scale equal to 10% of the inlet height are imposed at the inlet section. An average static pressure condition is set at the outlet section. The connection between static and rotating meshes is of "transient rotor-stator" type. This connection type allows to fully take into account the fluctuations generated by the RSI. The K-ε turbulence model is selected for this study. A convergence study with respect to the spatial resolution and timestep has been performed to ensure that the pressure fluctuations, the power output and the mass flow corresponding to the considered operation point are well converged. To obtain the mass flow of the chosen operating point from the model test, the net head imposed needs to be corrected by -3.0%. This discrepancy is due to the fact that only a portion of the turbine is modeled. Thus, losses in the spiral case and the draft tube are not computed. The theoretical power output evaluated by the torque on the runner differs by -4.1% from the measured value. This difference can be explained by the application of a reduced net head, the boundary conditions and differences between the geometry used for the simulation and the 3
5 real turbine geometry. Since this study aims at the prediction of the runner dynamic behaviour, emphasis is rather on the pressure fluctuations than the exact prediction of hydraulic conditions related to the model testing operating condition. In this perspective, the CFD calculation is satisfactory. A good way to quantify the RSI intensity is to track the dynamic torque fluctuation applied on the runner blades. Fig. 4 shows the blade torque curves with respect to time coming from the CFD calculation. Fig. 4 Blade torque curves with respect to time Each curve presents a phase shift and alternating peaks of high and low intensity. This phenomenon can be explained by the fact that the turbine has one stay vane for two wicket gates. The maximum fluctuation is about + / - 5.4% of the mean torque and the frequency of the first theoretical harmonic of the RSI is perfectly predicted by the CFD calculation. 5. Fluid-Structure Interaction Simulation The calculation including FSI is based on the connection of the two simulations presented in the previous sections. The bidirectional resolution scheme is presented in Fig. 5. Fig. 5 Bidirectional resolution scheme used for FSI simulations Fig. 6 Comparison between calculated and measured pressure fluctuations in the gap between the wicket gates and the runner blades (horizontal axes not at the same scale) 4
6 At the initial time, the runner is at rest and pressure fields coming from CFD calculation of the turbine under normal operating condition are applied impulsively. This starting condition is obviously not physical but allows the excitation of many modes in the vibration transient response of the runner such as the torsion and uprising modes. The identification of natural frequencies associated to these modes allows to validate the two-way FSI method by comparing the results with those calculated by a classical acoustic modal analysis. The hydraulic conditions of the FSI calculation are strictly the same as those corresponding to the CFD only calculation. The pressure fluctuations taken in the gap between the wicket gates and the runner blades are compared to those measured during the model testing. This comparison is shown in Fig. 6. The amplitude of calculated pressure fluctuations shows good agreement with measured ones. To validate the simulation including FSI, the displacement signals with respect to time are recorded at several material points attached to the runner. The positioning of these points is presented in Fig. 7. The displacement signals can be split into a static contribution and a dynamic contribution. The static contribution is first compared with a typical static analysis. A comparison of normalized static displacements according to the power output can be used in order to validate that the magnitude of the results given by the two-way FSI calculation are consistent. The differences between the displacements given by the two methods are presented in Table 3. Table 3 Comparison between static displacements obtained by the two-way FSI calculation and by a conventional static analysis Fig. 7 Location of material points where displacement signals are recorded Location Radial Displacement Tangential Displacement (%) (%) Crown N/D 7.1 Leading Edge Trailing Edge Band Given the assumptions outlined in Section 2, the differences obtained show that the FSI method is coherent considering the static displacements. The analysis of the dynamic contribution of the displacement signals recorded at the different material points allows the determination of natural frequencies. These signals are presented in Fig. 8 and 9. Fig. 8 Displacement signals recorded at the material points attached to the runner at the begin of simulation 5
7 The entire signals simulated are divided into four sub-sections for analysis purpose. Here is a description of the first three ones: I: Portion of the signals where the runner is subjected to the initial impulsive loading. The torsion modes are clearly involved (first and second orders) by the imposition of the full torque on the runner blades. Also, the resultant force generates a hydraulic axial thrust exciting the uprising mode. The higher order modes are quickly damped, leaving only the first order torsion mode. II: Portion of the signal where the first order torsion mode is basically dominant. All signals have the same phase during the first moments of portion II. For the last moments of this signal portion, a phase shift between the trailing edges due to RSI begins to settle. III: Portion of the signal where the runner is in transient vibration due to the RSI excitation. The phase shift of the blades begins to adjust. The leading edges have essentially zero phase shift between each other ones, while the trailing edges tend to have a phase shift of 120 degrees between them. Portion III corresponds to an adjustment time period where the entire runner structure acquires energy and synchronizes with the RSI excitation. Also, in portion III, the contribution of the torsion mode disappears since there is no compatible excitation coming from the flow. Fig. 9 shows the steady state portion of the displacement signals. Fig. 9 Displacement signals recorded at the material points on the runner after the reaching of the steady state In portion IV of the signals, the vibration is stationary. Not surprisingly, the points which experience the largest dynamic amplitude are those associated to the trailing edges, followed by those associated to the band and the leading edges. The signals recorded from the points attached to the crown do not show any significant variation. All signals have contributions from two frequencies: the frequency of the first harmonic provided by the RSI theory and the natural frequency corresponding to the 5-nodal-diameter mode which is 55% higher (see Table 4 for a summary of the natural frequencies identified). The excitation has the same 5-nodal-diameter configuration than the excited mode. Despite an important frequency mismatch, the geometric compatibility between the excitation and the mode exists. This compatibility explains the presence of 5-nodal-diameter mode contribution in the steady state signals. It can be seen from Fig. 9 that the signals recorded at the trailing edges are out of phase with each other ones. The maximum amplitude is found at point TE2 followed by point TE3. The minimum amplitude is found at point TE1. Analysis of band deformation amplitude can help to understand the causes of this phenomenon. Fig. 10 shows the radial dynamic amplitude of the points located at the bottom of the band with respect to time. According to Fig. 7, points BAND1 to BAND6 are distributed uniformly in azimuth on one 5 th of the runner. The radial amplitude of these points with respect to time shows a quasi-sinusoidal shape of the band which corresponds to the complete runner to a 5-nodal-diameter deformation. The variations to the perfect sine shape are related to the rigidity discontinuities caused by the presence of the blades. A nodal point where the amplitude does not vary with respect to time is located between points BAND6 and BAND1. From Fig. 7, it can be seen that this point corresponds to the junction of blade 1 to the band. This observation explains why point TE1 shows a smaller displacement than the homologous points which are amplified by the radial displacement of the band. 6
8 Fig. 10 Radial dynamic amplitude of the band with respect to time Table 4 presents a comparison between the natural frequencies obtained by the analysis of the dynamic portion of the displacement signals calculated by the two-way FSI method and a classical acoustic modal analysis. Table 4 Comparison of natural frequencies calculated by the two-way FSI method and the acoustic method Modal Analysis Acoustic Modal Analysis FSI Analysis Mode Shapes Nat. Freq. (Vaccum) Nat. Freq. (Water) Nat. Freq. (Water) (Hz) (Hz) (Hz) Torsion ND Uprising ND The natural frequencies predicted by the two-way FSI calculation and the acoustic calculation are very similar for all modes except for the torsion mode. Apart from this mode, the difference between the predictions does not exceed 3%. This error is of the same order as the typical error with measurements. For torsion mode, the difference reaches nearly 17%. A reduction in the torsion mode is due to the presence of balancing holes integrated to the geometry used in two-way FSI simulation. These holes are nonexistent for the geometry used with the acoustic simulation. This geometric difference, however, can not alone explain the difference obtained. It is possible that the presence of flow in the simulation using the two-way FSI method produces a significant increase in the fluid added mass when compared with the same runner in still water as modeled by the acoustic method. An extra fluid added mass tends to lower the related natural frequency. Fig. 11 shows the comparison of the 5-nodal-diameter mode calculated by the acoustic method and by the two-way FSI method. The results are very similar, which shows good consistency. Fig. 11 Amplitude contours of the 5-nodal-diameter mode calculated by the acoustic method and by the twoway FSI method 7
9 6. Consideration on the computational resources needed The FSI simulation presented in this paper requires a high amount of computation time before reaching the steady state for the dynamic response of the runner. Tables 5 and 6 show the characteristics of the computer used and the resources needed by the two-way FSI calculation respectively. Table 5 Characteristics of the computer used for FSI calculation Processor nb - Intel Core i7 920 Core nb - 4 RAM memory type - DDR3 RAM memory (Gig) 12 Table 6 Resources used by the two-way FSI calculation Solid Mesh (Node) Fluid Mesh (Node) Timestep (s) Simulation time (s) Computation time (Day) 95 RAM memory used (Gig) 10 The calculation time is excessive to allow the use of the two-way FSI method as standard analysis at the design stage of turbine runners. Nevertheless, improvements of computing time is possible for reaching the steady state. The injection of the runner static displacement under time-averaged hydraulic load can reduce the transient response time. Obviously, the use of a more powerful computer could further reduce the computation time. 7. Conclusion This paper aimed to assess the capability of the two-way FSI method introduced by ANSYS to provide an accurate prediction of the dynamic behaviour of a Francis turbine runner under operating condition. This method offers the advantage of taking into account the strong coupling between the solid and the fluid medium, conserving all the characteristics of fluid flow such as viscosity and turbulence. This feature may be of primary importance when the structure vibrates in the vicinity of resonance. For this condition, the dynamic amplification is very sensitive to the damping forces. The hydraulic portion of the simulation showed good agreement with measurements realized during the model testing. Without target values coming from prototype structural measurements, a comparison of the results obtained by the two-way FSI method can still be made with the results coming from conventional validated methods. This comparison has shown quite good agreement. The static displacements obtained by the two-way FSI method were similar to those obtained by a classical static analysis. Moreover, the natural frequencies obtained were very close to those obtained by conventional acoustic analysis. Although the method calculates the damping factor implicitly, no comparison measurement is currently available to allow the validation of this aspect. The prediction of the damping ratio will be the subject of future investigations. Despite the advantages of the two-way FSI method, the computation time remains currently excessive for its use in a standard design procedure. However, improvements in computation time can be achieved. Finally, it would be of interest to test the two-way FSI method for the prediction of the dynamic behaviour of turbine runners subjected to other hydraulic excitations than RSI, such as the release of von Karman vortices and the partial load vortex rope. Acknowledgments The authors would like to thank École Polytechnique de Montréal, Natural Sciences and Engineering Research Council of Canada and Alstom Hydro Canada Inc. for their contribution to this project. References [1] Jacquet-Richardet G. and Dal-Ferro C 1996 Reduction Method for Finite Element Dynamic Analysis of Submerged Turbomachinery Wheels Computers and Structures 61(6) [2] Sena M, Reynaud G and Kueny J L 1999 Dynamic Behaviour Improvement of Francis Turbine Runners Hydropower and Dams (1) 90-5 [3] Liang Q W, Rodriguez C G, Egusquiza E, Escaler X and Avellan F 2006 Modal Response of Hydraulic Turbine 8
10 Runners Proc. of 23 rd IAHR Symp. on Hydr. Machin. and Syst.(Yokohama, Japan) [4] Coutu A, Velagandula O and Nennemann B 2005 Francis Runner Forced Response Technology Waterpower XIV (Austin, US) [5] Lais S, Liang Q, Henggeler U and Weiss T 2008 Dynamic Analysis of Francis Runners - Experiment and Numerical Simulation Proc. of 24 th IAHR Symp. on Hydr. Machin. and Syst. (Foz de Iguassu, Brasil) [6] Roth S, Calmon M, Farhat M, Muench C, Huebner B and Avellan F 2009 Hydrodynamic Damping Identification from an Impulse Response of a Vibrating Blade Proc. of 3 rd Int. Meet. of the Workg. on Cavit. and Dyn. Probl. in Hydr. Machin. and Syst. (Brno, Czech Republic) [7] Dompierre F, Sabourin M and Pelletier D 2008 Simulation of Structure Vibration in Water Proc. of 24 th IAHR Symp. on Hydr. Machin. and Syst. (Foz de Iguassu, Brasil) 9
Life time assessment and plant operation optimization based on geometry scan and strain gauge testing START/STOP optimization
IGHEM 2014 The 10 th International conference on hydraulic efficiency measurements Itajuba, Brasil September 16 th - 18 th, 2014 XXXXXX Life time assessment and plant operation optimization based on geometry
More informationAnalysis of the dynamic response of pump-turbine runners- Part I: Experiment
Analysis of the dynamic response of pump-turbine runners- Part I: Experiment A Presas 1, C Valero 1, X Huang 1, E Egusquiza 1, M Farhat 2 and F Avellan 2 1 Center for Industrial Diagnostics, Technical
More informationTwo-way coupled fluid structure interaction simulation of a propeller turbine
IOP Conference Series: Earth and Environmental Science Two-way coupled fluid structure interaction simulation of a propeller turbine To cite this article: H Schmucker et al 2010 IOP Conf. Ser.: Earth Environ.
More informationNUMERICAL SIMULATION AND EXPERIMENTAL INVESTIGATION OF THE FLOW IN AN AXIAL TURBINE
IAHR OCTOBER 27-31, FOZ DO IGUASSU RESERVED TO IAHR NUMERICAL SIMULATION AND EXPERIMENTAL INVESTIGATION OF THE FLOW IN AN AXIAL TURBINE J.-M. Gagnon, C. Deschênes, G.D. Ciocan, M. Iliescu LAMH, 1065, avenue
More informationDesign optimization method for Francis turbine
IOP Conference Series: Earth and Environmental Science OPEN ACCESS Design optimization method for Francis turbine To cite this article: H Kawajiri et al 2014 IOP Conf. Ser.: Earth Environ. Sci. 22 012026
More informationDesign Optimization of a Weather Radar Antenna using Finite Element Analysis (FEA) and Computational Fluid Dynamics (CFD)
Design Optimization of a Weather Radar Antenna using Finite Element Analysis (FEA) and Computational Fluid Dynamics (CFD) Fernando Prevedello Regis Ataídes Nícolas Spogis Wagner Ortega Guedes Fabiano Armellini
More informationFluid structure interaction analysis: vortex shedding induced vibrations
Fluid structure interaction analysis: vortex shedding induced vibrations N. Di Domenico, M. E. * University of Rome «Tor Vergata», Department of Enterprise Engineering «Mario Lucertini» A. Wade, T. Berg,
More informationHydro-elastic analysis of a propeller using CFD and FEM co-simulation
Fifth International Symposium on Marine Propulsors smp 17, Espoo, Finland, June 2017 Hydro-elastic analysis of a propeller using CFD and FEM co-simulation Vesa Nieminen 1 1 VTT Technical Research Centre
More informationEffect of suction pipe leaning angle and water level on the internal flow of pump sump
IOP Conference Series: Earth and Environmental Science PAPER OPEN ACCESS Effect of suction pipe leaning angle and water level on the internal flow of pump sump To cite this article: Z-M Chen et al 216
More informationSimulations of the vortex in the Dellenback abrupt expansion, resembling a hydro turbine draft tube operating at part-load
Simulations of the vortex in the Dellenback abrupt expansion, resembling a hydro turbine draft tube operating at part-load H Nilsson Chalmers University of Technology, SE-412 96 Gothenburg, Sweden E-mail:
More informationCo-Simulation von Flownex und ANSYS CFX am Beispiel einer Verdrängermaschine
Co-Simulation von Flownex und ANSYS CFX am Beispiel einer Verdrängermaschine Benoit Bosc-Bierne, Dr. Andreas Spille-Kohoff, Farai Hetze CFX Berlin Software GmbH, Berlin Contents Positive displacement compressors
More informationNumerical study of rotor-stator interactions in a hydraulic turbine with Foam-extend
IOP Conference Series: Earth and Environmental Science PAPER OPEN ACCESS Numerical study of rotor-stator interactions in a hydraulic turbine with Foam-extend To cite this article: Cappato Romain et al
More informationANSYS Fluid Structure Interaction for Thermal Management and Aeroelasticity
ANSYS Fluid Structure Interaction for Thermal Management and Aeroelasticity Phil Stopford Duxford Air Museum 11th May 2011 2011 2010 ANSYS, Inc. All rights reserved. 1 ANSYS, Inc. Proprietary Fluid Structure
More informationUnsteady numerical simulation of the flow in the U9 Kaplan turbine model
IOP Conference Series: Earth and Environmental Science OPEN ACCESS Unsteady numerical simulation of the flow in the U9 Kaplan turbine model To cite this article: Ardalan Javadi and Håkan Nilsson 2014 IOP
More informationCFD Simulation of a dry Scroll Vacuum Pump including Leakage Flows
CFD Simulation of a dry Scroll Vacuum Pump including Leakage Flows Jan Hesse, Rainer Andres CFX Berlin Software GmbH, Berlin, Germany 1 Introduction Numerical simulation results of a dry scroll vacuum
More informationEvaluation of an improved mixing plane interface for OpenFOAM
IOP Conference Series: Earth and Environmental Science OPEN ACCESS Evaluation of an improved mixing plane interface for OpenFOAM To cite this article: M Beaudoin et al 2014 IOP Conf. Ser.: Earth Environ.
More informationTurbine-99 unsteady simulations Validation
IOP Conference Series: Earth and Environmental Science Turbine-99 unsteady simulations Validation To cite this article: M J Cervantes et al 2010 IOP Conf. Ser.: Earth Environ. Sci. 12 012014 View the article
More informationInvestigation of the fluid-structure interaction of a high head Francis turbine using OpenFOAM and Code_Aster
IOP Conference Series: Earth and Environmental Science PAPER OPEN ACCESS Investigation of the fluid-structure interaction of a high head Francis turbine using OpenFOAM and Code_Aster To cite this article:
More informationChallenge Problem 5 - The Solution Dynamic Characteristics of a Truss Structure
Challenge Problem 5 - The Solution Dynamic Characteristics of a Truss Structure In the final year of his engineering degree course a student was introduced to finite element analysis and conducted an assessment
More informationInvestigation of the critical submergence at pump intakes based on multiphase CFD calculations
Advances in Fluid Mechanics X 143 Investigation of the critical submergence at pump intakes based on multiphase CFD calculations P. Pandazis & F. Blömeling TÜV NORD SysTec GmbH and Co. KG, Germany Abstract
More informationTutorial. BOSfluids. Water hammer (part 3) Dynamic Analysis using Caesar II
BOSfluids Tutorial Water hammer (part 3) Dynamic Analysis using Caesar II The Water hammer tutorial is a 3 part tutorial describing the phenomena of water hammer in a piping system and how BOSfluids can
More informationAEROELASTICITY IN AXIAL FLOW TURBOMACHINES
von Karman Institute for Fluid Dynamics Lecture Series Programme 1998-99 AEROELASTICITY IN AXIAL FLOW TURBOMACHINES May 3-7, 1999 Rhode-Saint- Genèse Belgium CASE STUDIES IN TURBOMACHINERY AEROELASTICITY
More informationThe effect of runner cone design on pressure oscillation characteristics in a Francis hydraulic turbine
137 The effect of runner cone design on pressure oscillation characteristics in a Francis hydraulic turbine Z D Qian 1 *,WLi 1, W X Huai 1, and YLWu 2 1 State Key Laboratory of Water Resources and Hydropower
More informationCFD Modeling of a Radiator Axial Fan for Air Flow Distribution
CFD Modeling of a Radiator Axial Fan for Air Flow Distribution S. Jain, and Y. Deshpande Abstract The fluid mechanics principle is used extensively in designing axial flow fans and their associated equipment.
More informationThe Spalart Allmaras turbulence model
The Spalart Allmaras turbulence model The main equation The Spallart Allmaras turbulence model is a one equation model designed especially for aerospace applications; it solves a modelled transport equation
More informationOPTIMIZATION OF AXIAL HYDRAULIC TURBINES RUNNER BLADES USING HYDRODYNAMIC SIMULATION TECHNIQUES
Scientific Bulletin of the Politehnica University of Timisoara Transactions on Mechanics Special issue The 6 th International Conference on Hydraulic Machinery and Hydrodynamics Timisoara, Romania, October
More informationSimilar Pulley Wheel Description J.E. Akin, Rice University
Similar Pulley Wheel Description J.E. Akin, Rice University The SolidWorks simulation tutorial on the analysis of an assembly suggested noting another type of boundary condition that is not illustrated
More informationEstimating Vertical Drag on Helicopter Fuselage during Hovering
Estimating Vertical Drag on Helicopter Fuselage during Hovering A. A. Wahab * and M.Hafiz Ismail ** Aeronautical & Automotive Dept., Faculty of Mechanical Engineering, Universiti Teknologi Malaysia, 81310
More informationTurbocharger Design & Analysis Solutions. Bill Holmes Brad Hutchinson Detroit, October 2012
Turbocharger Design & Analysis Solutions Bill Holmes Brad Hutchinson Detroit, October 2012 Agenda ANSYS overview ANSYS TurboSystem Blade row solutions The ANSYS Transformation methods An example: turbocharger
More informationThank you for downloading one of our ANSYS whitepapers we hope you enjoy it.
Thank you! Thank you for downloading one of our ANSYS whitepapers we hope you enjoy it. Have questions? Need more information? Please don t hesitate to contact us! We have plenty more where this came from.
More informationUsing a Single Rotating Reference Frame
Tutorial 9. Using a Single Rotating Reference Frame Introduction This tutorial considers the flow within a 2D, axisymmetric, co-rotating disk cavity system. Understanding the behavior of such flows is
More informationParametric design of a Francis turbine runner by means of a three-dimensional inverse design method
IOP Conference Series: Earth and Environmental Science Parametric design of a Francis turbine runner by means of a three-dimensional inverse design method To cite this article: K Daneshkah and M Zangeneh
More information2: Static analysis of a plate
2: Static analysis of a plate Topics covered Project description Using SolidWorks Simulation interface Linear static analysis with solid elements Finding reaction forces Controlling discretization errors
More informationCoupled Analysis of FSI
Coupled Analysis of FSI Qin Yin Fan Oct. 11, 2008 Important Key Words Fluid Structure Interface = FSI Computational Fluid Dynamics = CFD Pressure Displacement Analysis = PDA Thermal Stress Analysis = TSA
More informationOptimization of Hydraulic Fluid Parameters in Automotive Torque Converters
Optimization of Hydraulic Fluid Parameters in Automotive Torque Converters S. Venkateswaran, and C. Mallika Parveen Abstract The fluid flow and the properties of the hydraulic fluid inside a torque converter
More informationAero-Vibro Acoustics For Wind Noise Application. David Roche and Ashok Khondge ANSYS, Inc.
Aero-Vibro Acoustics For Wind Noise Application David Roche and Ashok Khondge ANSYS, Inc. Outline 1. Wind Noise 2. Problem Description 3. Simulation Methodology 4. Results 5. Summary Thursday, October
More informationSAMCEF for ROTORS. Chapter 3.2: Rotor modeling. This document is the property of SAMTECH S.A. MEF A, Page 1
SAMCEF for ROTORS Chapter 3.2: Rotor modeling This document is the property of SAMTECH S.A. MEF 101-03-2-A, Page 1 Table of contents Introduction Introduction 1D Model 2D Model 3D Model 1D Models: Beam-Spring-
More informationResearch and Design working characteristics of orthogonal turbine Nguyen Quoc Tuan (1), Chu Dinh Do (2), Quach Thi Son (2)
GSJ: VOLUME 6, ISSUE 6, JUNE 018 116 Research and Design working characteristics of orthogonal turbine Nguyen Quoc Tuan (1), Chu Dinh Do (), Quach Thi Son () (1) Institute for hydro power and renewable
More informationThe Vibration Characteristics Analysis of Damping System of Wallmounted Airborne Equipment Based on FEM
IOP Conference Series: Earth and Environmental Science PAPER OPEN ACCESS The Vibration Characteristics Analysis of Damping System of Wallmounted Airborne Equipment Based on FEM To cite this article: Changqing
More informationUsing three-dimensional CURVIC contact models to predict stress concentration effects in an axisymmetric model
Boundary Elements XXVII 245 Using three-dimensional CURVIC contact models to predict stress concentration effects in an axisymmetric model J. J. Rencis & S. R. Pisani Department of Mechanical Engineering,
More informationPredicting the mechanical behaviour of large composite rocket motor cases
High Performance Structures and Materials III 73 Predicting the mechanical behaviour of large composite rocket motor cases N. Couroneau DGA/CAEPE, St Médard en Jalles, France Abstract A method to develop
More informationAnalysis of fluid-solid coupling vibration characteristics of probe based on ANSYS Workbench
Analysis of fluid-solid coupling vibration characteristics of probe based on ANSYS Workbench He Wang 1, a, Changzheng Zhao 1, b and Hongzhi Chen 1, c 1 Shandong University of Science and Technology, Qingdao
More informationThe ERCOFTAC centrifugal pump OpenFOAM case-study
3 rd IAHR International Meeting of the Workgroup on Cavitation and Dynamic Problems in Hydraulic Machinery and Systems, October 14-16, 009, Brno, Czech Republic The ERCOFTAC centrifugal pump OpenFOAM case-study
More informationNUMERICAL INVESTIGATION OF THE FLOW BEHAVIOR INTO THE INLET GUIDE VANE SYSTEM (IGV)
University of West Bohemia» Department of Power System Engineering NUMERICAL INVESTIGATION OF THE FLOW BEHAVIOR INTO THE INLET GUIDE VANE SYSTEM (IGV) Publication was supported by project: Budování excelentního
More informationUse of CFD in Design and Development of R404A Reciprocating Compressor
Purdue University Purdue e-pubs International Compressor Engineering Conference School of Mechanical Engineering 2006 Use of CFD in Design and Development of R404A Reciprocating Compressor Yogesh V. Birari
More information2008 International ANSYS Conference
2008 International ANSYS Conference Simulation of Added Mass Effect on Disc Vibrating in Fluid Using Fluid-Structure Interaction Coupling of ANSYS/CFX QIAN LIKE ANSYS Japan K.K. 2008 ANSYS, Inc. All rights
More informationNumerical Analysis of Tip Cavitation on Marine Propeller with Wake Alignment Using a Simple Surface Panel Method SQCM
Journal of Physics: Conference Series PAPER OPEN ACCESS Numerical Analysis of Tip Cavitation on Marine Propeller with Wake Alignment Using a Simple Surface Panel Method SQCM Related content - Hydrodynamics
More informationMesh Morphing and the Adjoint Solver in ANSYS R14.0. Simon Pereira Laz Foley
Mesh Morphing and the Adjoint Solver in ANSYS R14.0 Simon Pereira Laz Foley 1 Agenda Fluent Morphing-Optimization Feature RBF Morph with ANSYS DesignXplorer Adjoint Solver What does an adjoint solver do,
More informationComputational Modeling of the Three-Dimensional Flow in a Metallic Stator Progressing Cavity Pump
Computational Modeling of the Three-Dimensional Flow in a Metallic Stator Progressing Cavity Pump Emilio E. Paladino; João A. Lima and Rairam F. Almeida UFRN / DEM / PPGEM, Brazil Benno W. Assmann PETROBRAS
More informationComputational Fluid Dynamics modeling of a Water Flow Over an Ogee Profile
FINITE ELEMENT METHOD TECHNICAL REPORT Computational Fluid Dynamics modeling of a Water Flow Over an Ogee Profile ANSYS CFX 12 ENME 547 Dr. Sudak Matias Sessarego Written Report Due Date: Friday December
More informationSelf-Cultivation System
Development of a Microorganism Incubator using CFD Simulations Self-Cultivation System A comfortable mixing incubator to grow microorganism for agricultural, animal husbandry and ocean agriculture industries
More informationHydrocyclones and CFD
Design of Hydrocyclone Separation Equipment Using CFD Coupled with Optimization Tools David Schowalter 1, Rafiqul Khan 1, Therese Polito 2, and Tim Olson 3. (1) Fluent Inc., 10 Cavendish Court, Lebanon,
More informationPutting the Spin in CFD
w h i t e p a p e r Putting the Spin in CFD insight S U M MARY Engineers who design equipment with rotating components need to analyze and understand the behavior of those components if they want to improve
More informationMSC Software: Release Overview - MSC Nastran MSC Nastran 2014 RELEASE OVERVIEW
MSC Nastran 2014 Welcome to MSC Nastran 2014! Welcome to MSC Nastran 2014! The MSC Nastran 2014 release is focused on delivering new capabilities and performance required to solve multidisciplinary problems.
More informationIntroduction to ANSYS CFX
Workshop 03 Fluid flow around the NACA0012 Airfoil 16.0 Release Introduction to ANSYS CFX 2015 ANSYS, Inc. March 13, 2015 1 Release 16.0 Workshop Description: The flow simulated is an external aerodynamics
More informationSIMULATION OF PROPELLER-SHIP HULL INTERACTION USING AN INTEGRATED VLM/RANSE SOLVER MODELING.
SIMULATION OF PROPELLER-SHIP HULL INTERACTION USING AN INTEGRATED VLM/RANSE SOLVER MODELING. M.N.Senthil Prakash, Department of Ocean Engineering, IIT Madras, India V. Anantha Subramanian Department of
More informationWebinar: TwinMesh for Reliable CFD Analysis of Rotating Positive Displacement Machines
Webinar: TwinMesh for Reliable CFD Analysis of Rotating Positive Displacement Machines 14.07.2015 Dipl.-Ing. Jan Hesse Jan.hesse@cfx-berlin.de CFX Berlin Software GmbH Karl-Marx-Allee 90 A 10243 Berlin
More informationVERIFICATION OF CAMPBELL DIAGRAMS USING ANSYS - LINFLOW AND FUNDAMENTALS OF AEROELASTIC ANALYSES
VERIFICATION OF CAMPBELL DIAGRAMS USING ANSYS - LINFLOW AND FUNDAMENTALS OF AEROELASTIC ANALYSES Olcay ÇİÇEKDAĞ - Aeronautics Eng, MSc., FİGES A.Ş. CONTENTS 1) AIM 2) STRUCTURAL VIBRATION ANALYSES 2.1)
More informationFINITE ELEMENT MODELLING OF A TURBINE BLADE TO STUDY THE EFFECT OF MULTIPLE CRACKS USING MODAL PARAMETERS
Journal of Engineering Science and Technology Vol. 11, No. 12 (2016) 1758-1770 School of Engineering, Taylor s University FINITE ELEMENT MODELLING OF A TURBINE BLADE TO STUDY THE EFFECT OF MULTIPLE CRACKS
More informationNUMERICAL SIMULATION OF FLOW FIELD IN AN ANNULAR TURBINE STATOR WITH FILM COOLING
24 TH INTERNATIONAL CONGRESS OF THE AERONAUTICAL SCIENCES NUMERICAL SIMULATION OF FLOW FIELD IN AN ANNULAR TURBINE STATOR WITH FILM COOLING Jun Zeng *, Bin Wang *, Yong Kang ** * China Gas Turbine Establishment,
More informationCFD Simulation of Cavitation in an Internal Gear Pump
CFD Simulation of Cavitation in an Internal Gear Pump Dr. Andreas Spille-Kohoff Jan Hesse CFX Berlin Software GmbH Berlin andreas.spille@cfx-berlin.de Contents Introduction Geometry and mesh Simulation
More informationCFD ANALYSIS Of COMBINED 8-12 STAGES Of INTERMIDIATE PRESSURE STEAM TURBINE
CFD ANALYSIS Of COMBINED 8-12 STAGES Of INTERMIDIATE PRESSURE STEAM TURBINE 1st Author name : SHIVAKUMAR VASMATE, 2nd Author name : KAMALADEVI ANANDE. 1 Department of Mechanical Engineering, India 2 Department
More informationCFD Simulation of a Dry Scroll Vacuum Pump Including Leakage Flows
Purdue University Purdue e-pubs International Compressor Engineering Conference School of Mechanical Engineering 2016 CFD Simulation of a Dry Scroll Vacuum Pump Including Leakage Flows Jan Hesse CFX Berlin
More information2008 International ANSYS Conference
2008 International ANSYS Conference FEM AND FSI SIMULATIONS OF IMPACT LOADS ON GRP SUBSEA COMPOSITE COVERS Kjetil Rognlien, MSc Technical Consultant EDR AS, Norway 2008 ANSYS, Inc. All rights reserved.
More informationCHAPTER 4. Numerical Models. descriptions of the boundary conditions, element types, validation, and the force
CHAPTER 4 Numerical Models This chapter presents the development of numerical models for sandwich beams/plates subjected to four-point bending and the hydromat test system. Detailed descriptions of the
More informationOpenFOAM for CFD in water power and for international collaboration
OpenFOAM for CFD in water power and for international collaboration ASSOCIATE PROFESSOR HÅKAN NILSSON Outline of the presentation: OpenFOAM for CFD in water power - Overview of flow in Hydro Power Stations
More informationAnalysis Comparison between CFD and FEA of an Idealized Concept V- Hull Floor Configuration in Two Dimensions
2010 NDIA GROUND VEHICLE SYSTEMS ENGINEERING AND TECHNOLOGY SYMPOSIUM MODELING & SIMULATION, TESTING AND VALIDATION (MSTV) MINI-SYMPOSIUM AUGUST 17-19 DEARBORN, MICHIGAN Analysis Comparison between CFD
More informationNOISE PROPAGATION FROM VIBRATING STRUCTURES
NOISE PROPAGATION FROM VIBRATING STRUCTURES Abstract R. Helfrich, M. Spriegel (INTES GmbH, Germany) Noise and noise exposure are becoming more important in product development due to environmental legislation.
More informationMcNair Scholars Research Journal
McNair Scholars Research Journal Volume 2 Article 1 2015 Benchmarking of Computational Models against Experimental Data for Velocity Profile Effects on CFD Analysis of Adiabatic Film-Cooling Effectiveness
More informationModal analysis of a submerged gate
CDIF UPC ENSTA PARIS TECH Modal analysis of a submerged gate PPL Report Gabriel Cerdan Fernandez 6/10/2010 Tutors: Olivier Doare (ENSTA Paris Tech) Eduard Egusquiza (CDIF UPC) Abstract Hydraulic power
More informationCFD modelling of thickened tailings Final project report
26.11.2018 RESEM Remote sensing supporting surveillance and operation of mines CFD modelling of thickened tailings Final project report Lic.Sc.(Tech.) Reeta Tolonen and Docent Esa Muurinen University of
More informationCHAPTER 5 RANDOM VIBRATION TESTS ON DIP-PCB ASSEMBLY
117 CHAPTER 5 RANDOM VIBRATION TESTS ON DIP-PCB ASSEMBLY 5.1 INTRODUCTION Random vibration tests are usually specified as acceptance, screening and qualification tests by commercial, industrial, and military
More informationThe Great Mystery of Theoretical Application to Fluid Flow in Rotating Flow Passage of Axial Flow Pump, Part I: Theoretical Analysis
Proceedings of the 2nd WSEAS Int. Conference on Applied and Theoretical Mechanics, Venice, Italy, November 20-22, 2006 228 The Great Mystery of Theoretical Application to Fluid Flow in Rotating Flow Passage
More informationRBF Morph An Add-on Module for Mesh Morphing in ANSYS Fluent
RBF Morph An Add-on Module for Mesh Morphing in ANSYS Fluent Gilles Eggenspieler Senior Product Manager 1 Morphing & Smoothing A mesh morpher is a tool capable of performing mesh modifications in order
More informationCalculate a solution using the pressure-based coupled solver.
Tutorial 19. Modeling Cavitation Introduction This tutorial examines the pressure-driven cavitating flow of water through a sharpedged orifice. This is a typical configuration in fuel injectors, and brings
More informationDYNAMICS OF A VORTEX RING AROUND A MAIN ROTOR HELICOPTER
DYNAMICS OF A VORTEX RING AROUND A MAIN ROTOR HELICOPTER Katarzyna Surmacz Instytut Lotnictwa Keywords: VORTEX RING STATE, HELICOPTER DESCENT, NUMERICAL ANALYSIS, FLOW VISUALIZATION Abstract The main goal
More informationFluid Structure Interaction Modeling for Geroler Motor Performance Prediction using FEA and CFD Coupled Approach
flotek.g 2017- Innovative Solutions in Flow Measurement and Control - Oil, Water and Gas August 28-30, 2017, FCRI, Palakkad, Kerala, India Fluid Structure Interaction Modeling for Geroler Motor Performance
More informationThe viscous forces on the cylinder are proportional to the gradient of the velocity field at the
Fluid Dynamics Models : Flow Past a Cylinder Flow Past a Cylinder Introduction The flow of fluid behind a blunt body such as an automobile is difficult to compute due to the unsteady flows. The wake behind
More informationModeling Submerged Structures Loaded by Underwater Explosions with ABAQUS/Explicit
Modeling Submerged Structures Loaded by Underwater Explosions with ABAQUS/Explicit David B. Woyak ABAQUS Solutions Northeast, LLC Abstract: Finite element analysis can be used to predict the transient
More informationEnhancement of a large injection system for steam turbines
GE Oil & Gas Leonardo Nettis, GE Oil & Gas Enzo Imparato, GE Oil & Gas Lorenzo Cosi, GE Oil & Gas DOWNSTREAM TECHNOLOGY SOLUTIONS PRODUCTS & SERVICES Enhancement of a large injection system for steam turbines
More informationInfluence of geometric imperfections on tapered roller bearings life and performance
Influence of geometric imperfections on tapered roller bearings life and performance Rodríguez R a, Calvo S a, Nadal I b and Santo Domingo S c a Computational Simulation Centre, Instituto Tecnológico de
More informationCFD Analysis of a Fully Developed Turbulent Flow in a Pipe with a Constriction and an Obstacle
CFD Analysis of a Fully Developed Turbulent Flow in a Pipe with a Constriction and an Obstacle C, Diyoke Mechanical Engineering Department Enugu State University of Science & Tech. Enugu, Nigeria U, Ngwaka
More informationRotating Moving Boundary Analysis Using ANSYS 5.7
Abstract Rotating Moving Boundary Analysis Using ANSYS 5.7 Qin Yin Fan CYBERNET SYSTEMS CO., LTD. Rich Lange ANSYS Inc. As subroutines in commercial software, APDL (ANSYS Parametric Design Language) provides
More information17. SEISMIC ANALYSIS MODELING TO SATISFY BUILDING CODES
17. SEISMIC ANALYSIS MODELING TO SATISFY BUILDING CODES The Current Building Codes Use the Terminology: Principal Direction without a Unique Definition 17.1 INTRODUCTION { XE "Building Codes" }Currently
More informationProblem description. The FCBI-C element is used in the fluid part of the model.
Problem description This tutorial illustrates the use of ADINA for analyzing the fluid-structure interaction (FSI) behavior of a flexible splitter behind a 2D cylinder and the surrounding fluid in a channel.
More informationVibration Analysis of Low Pressure Stages of Large Steam Turbines with ANSYS
Vibration Analysis of Low Pressure Stages of Large Steam Turbines with ANSYS L. Moroz, L. G. Romanenko SoftInWay, Inc., Burlington, MA 01803 Abstract: High cycle fatigue (HCF) plays a significant role
More informationSummary of the main PROBAND project results
Summary of the main PROBAND project results WP2: WP2 was dedicated to the development and validation broadband noise prediction methods. Once validated on non rotating airfoils in WP2, these methods were
More informationTHE INFLUENCE OF ROTATING DOMAIN SIZE IN A ROTATING FRAME OF REFERENCE APPROACH FOR SIMULATION OF ROTATING IMPELLER IN A MIXING VESSEL
Journal of Engineering Science and Technology Vol. 2, No. 2 (2007) 126-138 School of Engineering, Taylor s University College THE INFLUENCE OF ROTATING DOMAIN SIZE IN A ROTATING FRAME OF REFERENCE APPROACH
More informationTurbomachinery Applications with STAR-CCM+ Turbomachinery Sector Manager
Turbomachinery Applications with STAR-CCM+ Fred Mendonça Fred Mendonça Turbomachinery Sector Manager An Integrated Solution The applications of the software seem to be infinite. The user-friendly A single
More informationWind tunnel study on load combination including torsion for design of medium-rise buildings
The Eighth Asia-Pacific Conference on Engineering, December 10 14, 2013, Chennai, India tunnel study on load combination including torsion for design of medium-rise buildings Mohamed Elsharawy, Ted Stathopoulos,
More informationNUMERICAL ANALYSIS OF CENTRIFUGAL PUMP IMPELLER FOR PERFORMANCE IMPROVEMENT
Int. J. Chem. Sci.: 14(2), 2016, 1148-1156 ISSN 0972-768X www.sadgurupublications.com NUMERICAL ANALYSIS OF CENTRIFUGAL PUMP IMPELLER FOR PERFORMANCE IMPROVEMENT S. KALIAPPAN, M. D. RAJKAMAL and D. BALAMURALI
More informationAdvanced Multi-Body Modeling of Rotor Blades Validation and Application
Advanced Multi-Body Modeling of Rotor s Validation and Application For efficient wind turbine energy production, larger rotors are required for which slender blades with increased flexibility are often
More informationEng Ship Structures 1 L E C T U R E 1 0 : F I N I T E E L E M E N T T E C H N I Q U E S I N S H I P S T R U C T U R A L D E S I G N
Eng. 6002 Ship Structures 1 L E C T U R E 1 0 : F I N I T E E L E M E N T T E C H N I Q U E S I N S H I P S T R U C T U R A L D E S I G N Contents Introduction Linear Analysis Static Non-linear Analysis
More informationAxisymmetric Viscous Flow Modeling for Meridional Flow Calculation in Aerodynamic Design of Half-Ducted Blade Rows
Memoirs of the Faculty of Engineering, Kyushu University, Vol.67, No.4, December 2007 Axisymmetric Viscous Flow Modeling for Meridional Flow alculation in Aerodynamic Design of Half-Ducted Blade Rows by
More informationComputational Fluid Dynamics Simulation of a Rim Driven Thruster
Computational Fluid Dynamics Simulation of a Rim Driven Thruster Aleksander J Dubas, N. W. Bressloff, H. Fangohr, S. M. Sharkh (University of Southampton) Abstract An electric rim driven thruster is a
More informationParallel Computation of Industrial Flows on the Cray T3D
Parallel Computation of Industrial Flows on the Cray T3D Olivier Byrde, David Cobut and Mark L. Sawley, Institut de Machines Hydrauliques et de Mécanique des Fluides, Ecole Polytechnique Fédérale de Lausanne,
More informationRyian Hunter MAE 598
Setup: The initial geometry was produced using the engineering schematics provided in the project assignment document using the ANSYS DesignModeler application taking advantage of system symmetry. Fig.
More informationGuidelines for proper use of Plate elements
Guidelines for proper use of Plate elements In structural analysis using finite element method, the analysis model is created by dividing the entire structure into finite elements. This procedure is known
More informationA design influence on the mechanical compliance and fracture resistance of railway wheel
Applied and Computational Mechanics 5 (2011) 197 204 A design influence on the mechanical compliance and fracture resistance of railway wheel P. Navrátil a,,p.janíček a, L. Brabenec a, M. Matug a, P. Marcián
More informationPreliminary investigation into two-way fluid structure interaction of heliostat wind loads Josh Wolmarans
Preliminary investigation into two-way fluid structure interaction of heliostat wind loads Josh Wolmarans Supervisor: Prof Ken Craig Clean Energy Research Group (CERG), Department of Mechanical and Aeronautical
More information