CFD Study of a Darreous Vertical Axis Wind Turbine
|
|
- Oswald Goodwin
- 6 years ago
- Views:
Transcription
1 CFD Study of a Darreous Vertical Axis Wind Turbine Md Nahid Pervez a and Wael Mokhtar b a Graduate Assistant b PhD. Assistant Professor Grand Valley State University, Grand Rapids, MI , mokhtarw@gvsu.edu Introduction GO GREEN! is a widely used buzzword of these days for most of the companies and even for the policy makers. Some significant steps for saving the environment are - recycling the pop cans, using bio-degradable packaging materials, reducing the wastage of papers, using more efficient electric appliances, and using more efficient cars. But how far are we in the journey to going green? In the year 2010 only eight percent of the total 98.1 quads of energy consumption of US came from renewable energy sources 1 which roughly is eight quads, in which only 12% of the energy is from the wind energy 1. So the statistics tell us that we still have a long way to go. US government has a plan to obtain 20% of the total electric energy supply from renewable energy sources by the year Wind energy offers a promising renewable energy source and wind turbines are the only way to extract energy from the wind. HAWT (Horizontal Axis Wind Turbines) are widely used from the early days to harvest the wind energy. However VAWT (Vertical Axis Wind Turbine) are relatively new technology and proved to be very effective in lower wind speed locations such as cities. CFD (Computational Fluid Dynamics) is a very powerful tool for examining the flow characteristics of a complex system like the HAWT. In this paper, flow characteristics around a VAWT is presented using CFD tool. Literature Review A technical study was presented by D. Ayhan et. al. 3 about the wind speed variations and flow characteristics in city area. The boundary layer in a city, effect of building geometry on the boundary layer and the micro wind flow around the buildings were presented with the help of CFD tools. Different types of turbines for harnessing the energy were also suggested in that paper. An experimental study was done by R. Howell et. al. 4. The airfoil analyzed in that study was NACA The chord length of the turbine was 100 mm and the length was limited to 400 mm. they did experiment on both 2 bladed (solidity of 1) and 3 bladed turbines (solidity of 0.67). The low speed wind tunnel where the tests were performed had a square test section of 1.2m X 1.2m dimension. The reason for that experiment was to get a set of experimental results to compare with a CFD model. From the study it was found that the predicted performance from
2 the 2D study was much higher than the 3D experimental results. Dynamic behavior of vortices over the tip of the turbine blade is responsible for that, according to the authors. A CFD study of an unconventionally designed VAWT was presented by S. McTavish et. al. 5. The authors made a CFD model of a wind turbine of novel design for mainly micro scale power generation. Several modifications of a VAWT are experimented and studied to improve the power coefficient of the VAWT. One particular modification is incorporating a stator guide vane. A CFD study on that is presented by K. Pope et. al. 6. A zephyr made VAWT was studied in that paper. One particular problem of a VAWT is, it is not self-starting. To eliminate this problem asymmetric airfoils are used normally. An experimental study was performed on a VAWT with asymmetric airfoil by M. Takao et. al. 7. The airfoil used in that study was NACA4518 with stator guide vane. Present Work For the simulation of a VAWT, a step by step work flow was maintained. In the beginning, a 2D analysis was performed for the NACA4518 airfoil and its performance was observed for low speed wind. A profile of a NACA4518 is shown in figure NACA 4518 Figure 1: Profile of a NACA4518 airfoil As the airfoil was a blade of a VAWT, it would be subjected to positive and negative angle of attack. So the angle of attack was varied from -12 to +12. And the results are presented. Then a 3D model of an airfoil was simulated. Like the 2D analysis, the results of negative and positive angle of attack are presented. And finally a simplified 3D model of a VAWT with 3 blades was simulated. The airflow structure and other major flow characteristics around the turbine were presented. All of the models of the wind turbine used in the study were done by the CAD software SolidWorks TM. The length of the wind turbine was m (5 feet). The chord length was m (5 inch). CAD models are shown in figures 2, 3 and 4.
3 Figure 2 2D model Figure 3 3D model Figure 4 Simplified turbine model The applicability of VAWT in the city area is promising. So throughout the analysis the wind speed was maintained at 6.71 m/s (15 mph). It is the average speed of the city of Johnston Island, PC 8. The reason for this city is, it has a very decent wind speed throughout the year 8. Same wind speed was maintained for the 2D, 3D and simplified turbine model. The angle of attack was varied to observe the characteristics for 2D and 3D. Table 1 displays a summary of the different simulations. Table 1 Simulation Type Angle of Attack Speed (m/s) 2D Model -12, -8, -4, 0, 4, 8, D Model -8, -4, 0, 4, Rotation of the simplified turbine model was simulated by applying a tangential velocity at the walls of the rotor. The rotational velocity was 100 rpm. The orientation of the simplified model of the turbine was rotated from 0 to 120. The full performance in the whole 360 region is found by just repeating the results from 0 to 120. Table 2 shows the different orientations of the rotor that were simulated. Table 2 Simulation Type Orientation Angle Speed (m/s) Simplified 3D model of the turbine rotor. 0, 15,30,45,60,75, ,105,120 Computational Method The simulations were performed using STAR CCM+ TM commercial software. It was developed by CD-Adapco, Inc. and uses computational finite volume method for solving. For this study segregated flow solver was used. SST k- turbulence model was used for turbulence model. For the 2D study the numerical domain had a thickness of one chord length of the airfoil. The size of the numerical domain was large enough so that the domain boundary do not affect the simulation results. Figure 5 shows the meshed numerical domain with the airfoil inside it. Note that the mesh on that figure 5 is the surface mesh. For the surface mesh, surface remesher model was used. Trimmer volume mesh model was used to generate the volume mesh. The cells were
4 clustered to capture the curvature of the airfoil. Figure 7 shows the growth rate of the mesh as it moves outward in the domain. Figures 6 and 7 show the surface and volume mesh of the 2D airfoil respectively. Figure 5 2D surface mesh of numerical domain Figure 6 2D surface mesh of airfoil Figure 7 2D volume mesh of numerical domain Figure 8 2D volume mesh of airfoil Near the airfoil, to capture the boundary layer, prism layers were used. The thickness of the boundary layer was determined by repetitive trials so that it can capture the physics of boundary layer. Volumetric control was also used to cluster the cells around the airfoil to capture the turbulence and flow separation. Figures 9 and 10 show the boundary layer and the volumetric control region of the 2D study respectively.
5 Figure 9 Prism layers to capture boundary layer Figure 10 Volumetric control to cluster cells around the airfoil Similar approach was followed to simulate the 3D airfoil. For the 3D case only half of the airfoil simulated with a symmetric boundary to reduce the computational time. Figures 11 and 13 show the numerical domain with surface mesh and volume mesh for 3D case respectively. Figures 12 and 14 show the airfoil with surface mesh and volume mesh respectively.
6 Figure 11 Surface mesh of domain of 3D model Figure 12 Surface mesh of airfoil of 3D model Figure 13 Volume mesh of domain of 3D model Figure 14 Volume mesh of airfoil of 3D model For the simplified turbine model the numerical domain had a shape of cylinder. Volumetric control was used to cluster the cells around the turbine to capture the physics more accurately. Boundary layer was used to capture the boundary layer. Figures 15 and 16 show the surface meshes of the numerical domain and the rotor and figures 17 and 18 show the volume mesh of those. Figure 15 Surface mesh of numerical domain Figure 16 Surface mesh of simplified turbine
7 Figure 17 Volume mesh of numerical domain Figure 18 Volume mesh of simplified turbine The cell size was increased as it moves outward from the turbine. Figure 19 show the volumetric control of the cell and gradual increase of the cell size. Figure 19 Volumetric control to cluster cells around the turbine
8 The major parameters of the 2D and 3D cases are tabulated in table 3. Table 3 Parameters 2D Airfoil 3D airfoil Simplified Turbine Geometry: Chord length : m (5 inch) Speed: 6.71 m/s (15 mph) Chord length : m (5 inch) Length : m (2.5 feet) Chord length : m (5 inch) Length : m (5 feet) Reynolds number: Speed: 6.71 m/s (15 L/D ratio: mph) Width of the turbine: Reynolds number: 3 feet Speed: 6.71 m/s (15 mph) Model: Trimmer volume Trimmer volume Trimmer volume mesh mesh mesh Number of cells: Number of cells: Number of cells: Segregated flow SST k-ω turbulence model Segregated flow SST k-ω turbulence model Segregated flow SST k-ω turbulence model Solver: AMG linear solver AMG linear solver AMG linear solver CFD Results and Discussions The 2D analysis was performed to characterize the performance of the airfoil. One of the major challenges for CFD is to capture the boundary layer and separation region properly. Figure 20 shows the boundary layer and the prism layers used to capture it. Figure 20 Prism layers capturing the boundary layer
9 From the pressure contour (figure 21) and the velocity vector around the airfoil (figure 22) the stagnation point is visible. A minute separation region is also found from the velocity vector (figure 22). Figure 23 show the stream line around the airfoil. Note that all of the results are of the 0 angle of attack simulation. Figure 21 Pressure contours around the airfoil for 2D case Figure 22 Velocity distribution around the airfoil for 2D case Figure 23 Streamline around the airfoil for 2D case The coefficient of lift is the most important result for this simulation. The airfoil will be subjected to a variable angle of attack both in positive and negative direction. So both positive and negative angle of attack cases were simulated. Coefficients of lift for different angles of attack are shown in figure 24 for 2D simulation. Lift coefficient Angle of attack Figure 24 Lift of coefficient for 2D simulation Lift Coefficient Angle of attack Figure 25 Lift of coefficient for 3D simulation
10 The 3D simulations were done in a similar fashion. The coefficients of lift for different angles of attack can be found in figure 25. Notable fact is that, the performance parameter which is the coefficients of lift of the airfoil decreases in 3D simulation cases. The coefficient of lift has the highest value of 0.75 in 3D case where in 2D case the highest value was One of the main objectives of this study was to visualize the flow structure around the VAWT wind turbine. The complexity of the flow structure makes it hard to visualize. Figure 26 shows the stream lines around the turbine. The turbine blades were used to seed the streamlines. Figure 26 Streamline around the simplified turbine The velocity magnitude around the turbine in figure 27 shows a large separation of flow region due to the orientation of the airfoil. The lift generated by the wing would provide the moment or torque to rotate. So at different orientations the torque would be different. In current orientation, among the three blades one blade is facing the wind in a perpendicular position which is creating a huge separation region.
11 Figure 27 Velocity profile around the turbine The pressure contour around the rotor in figure 28 is supporting the fact of separation of flow due to orientation of the blades. Figure 28 Pressure contours around the turbine The rotational velocity of the simplified turbine was simulated by adding a tangential velocity. A closer look on the velocity vector around the blades from figure 29 shows the tangential velocity.
12 Figure 29 Velocity distribution at the vicinity of the turbine wall The moment is the main indicator for the turbine power generation. But the moment varies due to the different orientation of the blades. The wind direction was varied from 0 to 120 and the moment around the rotor calculated from the simulation. As it is a 3 bladed rotor, the moments at other angles were found by repeating the results. Figure 30 show moments generated by the rotor Moment at angle Average moment Figure 30 Moment generated by turbine The average torque was found N-m at 100 rpm. The turbine produces watt of power. The results show that the turbine has a very low efficiency. Further modification of the turbine structure and proper modeling of the turbine in CFD will provide more accurate results.
13 Conclusion CFD is very effective for visualizing the complex flow structure around the vertical axis wind turbine. This study had primary objective to visualize the flow structure, analyze the performances of the airfoil NACA 4518 and act as preliminary study for a complex unsteady analysis of a VAWT. 2D, 3D and simplified model of a VAWT is simulated and results are presented in this study. The flow structure is presented for the simplified turbine in the form of streamlines. Performance parameter which is the coefficient of lift is presented for different angle of attacks. Performance differences in 2D and 3D studies are also observed. For simplicity, the rotational motion of the turbine was simulated by adding tangential velocity on the walls of the rotor. This is a simplified approach to a complex fluid-solid interaction problem. From th performance of the VAWT is relatively lower than that of a HAWT. However significant structural modifications and proper mathematical modeling will provide accurate results. References 1. U. S. DOE, Energy Information Administration (EIA) (2011) Monthly Energy Review September U. S.DOE, Energy Efficiency and Renewable Energy 20% Wind Energy by 2030 July Ayhan, D., Saglam, S., A technical review of building-mounted power systems and a sample simulation model, Renewable and Sustainable Energy Reviews 16 (2012) Howell, R., Qin, N., Edwards, J., Durrani, N., Wind tunnel and numerical study of a small vertical axis wind turbine, Renewable Energy 35 (2010) Mctavish, S., Feszty, D., Sankar, T., Steady and rotating computational fluid dynamics simulations of a novel vertical axis wind turbine for small-scale power generation, Renewable Energy 41 (2012) Pope, K., Rodrigues, V., Doyle, R., Tsopelas, A., Gravelsins, R., Naterer, G. F., Tsang, E., Effect of stator vanes on power coefficients of a zephyr vertical axis wind turbine, Renewable Energy 35 (2010) Takao, M., Kuma, H., Maeda, T., Kamada, Y., Oki, M., Minoda, A., A Straight-bladed Vertical Axis Wind Turbine with a Direct Guide Vane Row Effect of Guide Vane Geometry on the Performance, Journal of thermal Science Vol. 18, No. 1 (2009) Comparative Climatic Data, Wind Average Wind Speed (MPH), Retrieved from the web on December 2011, site: National Climatic Data Center, U. S. Department of Commerce.
Transition Flow and Aeroacoustic Analysis of NACA0018 Satish Kumar B, Fred Mendonç a, Ghuiyeon Kim, Hogeon Kim
Transition Flow and Aeroacoustic Analysis of NACA0018 Satish Kumar B, Fred Mendonç a, Ghuiyeon Kim, Hogeon Kim Transition Flow and Aeroacoustic Analysis of NACA0018 Satish Kumar B, Fred Mendonç a, Ghuiyeon
More informationCOMPUTATIONAL MODELING OF WIND ENERGY SYSTEMS
The Eighth Asia-Pacific Conference on Wind Engineering, December 10 14, 2013, Chennai, India COMPUTATIONAL MODELING OF WIND ENERGY SYSTEMS T. Shah 1, R. Prasad 2 and M. Damodaran 3 1 Project Associate,
More informationUnsteady flow simulation of a vertical axis wind turbine: a two-dimensional study
EngD Conference, 2 nd July 213 Unsteady flow simulation of a vertical axis wind turbine: a two-dimensional study R. Nobile 1, *, M. Vahdati, J.F. Barlow, A. Mewburn-Crook 2 1 TSBE Centre, University of
More informationIntroduction to ANSYS CFX
Workshop 03 Fluid flow around the NACA0012 Airfoil 16.0 Release Introduction to ANSYS CFX 2015 ANSYS, Inc. March 13, 2015 1 Release 16.0 Workshop Description: The flow simulated is an external aerodynamics
More informationNumerische Untersuchungen von Windkraftanlagen: Leistung, Wake und Steuerungsstrategien
Fachtagung Lasermethoden in der Strömungsmesstechnik 8. 10. September 2015, Dresden Numerische Untersuchungen von Windkraftanlagen: Leistung, Wake und Steuerungsstrategien Numerical Investigations of Wind
More informationCFD VALIDATION FOR SURFACE COMBATANT 5415 STRAIGHT AHEAD AND STATIC DRIFT 20 DEGREE CONDITIONS USING STAR CCM+
CFD VALIDATION FOR SURFACE COMBATANT 5415 STRAIGHT AHEAD AND STATIC DRIFT 20 DEGREE CONDITIONS USING STAR CCM+ by G. J. Grigoropoulos and I..S. Kefallinou 1. Introduction and setup 1. 1 Introduction The
More informationMcNair Scholars Research Journal
McNair Scholars Research Journal Volume 2 Article 1 2015 Benchmarking of Computational Models against Experimental Data for Velocity Profile Effects on CFD Analysis of Adiabatic Film-Cooling Effectiveness
More informationOpenFOAM capabilities for the analysis of Vertical-Axis Wind Turbine aerodynamics
OpenFOAM capabilities for the analysis of Vertical-Axis Wind Turbine aerodynamics Diego Domínguez 1, a), Daniel Fernández 1, Tim De Troyer 2, Mark C. Runacres 2 1 Aerospace Engineering Area, Universidad
More informationDynamic stall for a Vertical Axis Wind Turbine in a two-dimensional study
Dynamic stall for a Vertical Axis Wind Turbine in a two-dimensional study R. Nobile 1,*, M. Vahdati 1, J. Barlow 1, A. Mewburn-Crook 2 1 University of Reading, Reading, UK 2 Wind Dam Renewables Ltd, Swansea,
More informationCFD Simulations of Flow over Airfoils:
CFD Simulations of Flow over Airfoils: An Analysis of Wind Turbine Blade Aerodynamics By: John Hamilla, Mechanical Engineering Advisor: Maria-Isabel Carnasciali, Ph.D. Abstract Wind turbines are rapidly
More informationApplication of STAR-CCM+ to Helicopter Rotors in Hover
Application of STAR-CCM+ to Helicopter Rotors in Hover Lakshmi N. Sankar and Chong Zhou School of Aerospace Engineering, Georgia Institute of Technology, Atlanta, GA Ritu Marpu Eschol CD-Adapco, Inc.,
More informationHow to Enter and Analyze a Wing
How to Enter and Analyze a Wing Entering the Wing The Stallion 3-D built-in geometry creation tool can be used to model wings and bodies of revolution. In this example, a simple rectangular wing is modeled
More informationApplication of Wray-Agarwal Turbulence Model for Accurate Numerical Simulation of Flow Past a Three-Dimensional Wing-body
Washington University in St. Louis Washington University Open Scholarship Mechanical Engineering and Materials Science Independent Study Mechanical Engineering & Materials Science 4-28-2016 Application
More informationKeywords: CFD, aerofoil, URANS modeling, flapping, reciprocating movement
L.I. Garipova *, A.N. Kusyumov *, G. Barakos ** * Kazan National Research Technical University n.a. A.N.Tupolev, ** School of Engineering - The University of Liverpool Keywords: CFD, aerofoil, URANS modeling,
More informationResearch and Design working characteristics of orthogonal turbine Nguyen Quoc Tuan (1), Chu Dinh Do (2), Quach Thi Son (2)
GSJ: VOLUME 6, ISSUE 6, JUNE 018 116 Research and Design working characteristics of orthogonal turbine Nguyen Quoc Tuan (1), Chu Dinh Do (), Quach Thi Son () (1) Institute for hydro power and renewable
More informationHigh-Lift Aerodynamics: STAR-CCM+ Applied to AIAA HiLiftWS1 D. Snyder
High-Lift Aerodynamics: STAR-CCM+ Applied to AIAA HiLiftWS1 D. Snyder Aerospace Application Areas Aerodynamics Subsonic through Hypersonic Aeroacoustics Store release & weapons bay analysis High lift devices
More informationComputational Analysis of a Wing Oscillator
Western Michigan University ScholarWorks at WMU Master's Theses Graduate College 8-2012 Computational Analysis of a Wing Oscillator Ryne Derrick Radermacher Western Michigan University, rhyno466@gmail.com
More informationTHE APPLICATION OF AN ATMOSPHERIC BOUNDARY LAYER TO EVALUATE TRUCK AERODYNAMICS IN CFD
THE APPLICATION OF AN ATMOSPHERIC BOUNDARY LAYER TO EVALUATE TRUCK AERODYNAMICS IN CFD A SOLUTION FOR A REAL-WORLD ENGINEERING PROBLEM Ir. Niek van Dijk DAF Trucks N.V. CONTENTS Scope & Background Theory:
More informationRIBLETS FOR AIRFOIL DRAG REDUCTION IN SUBSONIC FLOW
RIBLETS FOR AIRFOIL DRAG REDUCTION IN SUBSONIC FLOW Baljit Singh Sidhu, Mohd Rashdan Saad, Ku Zarina Ku Ahmad and Azam Che Idris Department of Mechanical Engineering, Faculty of Engineering, Universiti
More informationCFD SIMULATIONS OF HORIZONTAL AXIS WIND TURBINE (HAWT) BLADES FOR VARIATION WITH WIND SPEED
2 nd National Conference on CFD Applications in Power and Industry Sectors January 28-29, 2009, Hydrabad, India CFD SIMULATIONS OF HORIZONTAL AXIS WIND TURBINE (HAWT) BLADES FOR VARIATION WITH WIND SPEED
More informationAccurate and Efficient Turbomachinery Simulation. Chad Custer, PhD Turbomachinery Technical Specialist
Accurate and Efficient Turbomachinery Simulation Chad Custer, PhD Turbomachinery Technical Specialist Outline Turbomachinery simulation advantages Axial fan optimization Description of design objectives
More informationNumerical Analysis of Effect of Pitch Angle on a Small Scale Vertical Axis Wind Turbine
Numerical Analysis of Effect of Pitch Angle on a Small Scale Vertical Axis Wind Turbine Bose Sumantraa R., Chandramouli S., Premsai T. P., Prithviraj P., Vivek M., V. Ratna Kishore Department of Mechanical
More informationCFD Analysis of conceptual Aircraft body
CFD Analysis of conceptual Aircraft body Manikantissar 1, Dr.Ankur geete 2 1 M. Tech scholar in Mechanical Engineering, SD Bansal college of technology, Indore, M.P, India 2 Associate professor in Mechanical
More informationTurbomachinery Applications with STAR-CCM+ Turbomachinery Sector Manager
Turbomachinery Applications with STAR-CCM+ Fred Mendonça Fred Mendonça Turbomachinery Sector Manager An Integrated Solution The applications of the software seem to be infinite. The user-friendly A single
More informationIntegration of an unsteady nonlinear lifting line free wake algorithm in a wind turbine design framework
Integration of an unsteady nonlinear lifting line free wake algorithm in a wind turbine design framework Introduction D. Marten, G. Pechlivanoglou, C. N. Nayeri, C. O. Paschereit TU Berlin, Institute of
More informationMissile External Aerodynamics Using Star-CCM+ Star European Conference 03/22-23/2011
Missile External Aerodynamics Using Star-CCM+ Star European Conference 03/22-23/2011 StarCCM_StarEurope_2011 4/6/11 1 Overview 2 Role of CFD in Aerodynamic Analyses Classical aerodynamics / Semi-Empirical
More informationIntroduction to CFX. Workshop 2. Transonic Flow Over a NACA 0012 Airfoil. WS2-1. ANSYS, Inc. Proprietary 2009 ANSYS, Inc. All rights reserved.
Workshop 2 Transonic Flow Over a NACA 0012 Airfoil. Introduction to CFX WS2-1 Goals The purpose of this tutorial is to introduce the user to modelling flow in high speed external aerodynamic applications.
More informationEstimation of Flow Field & Drag for Aerofoil Wing
Estimation of Flow Field & Drag for Aerofoil Wing Mahantesh. HM 1, Prof. Anand. SN 2 P.G. Student, Dept. of Mechanical Engineering, East Point College of Engineering, Bangalore, Karnataka, India 1 Associate
More informationCoupling STAR-CCM+ with Optimization Software IOSO by the example of axial 8-stages jet engine compressor.
Coupling STAR-CCM+ with Optimization Software IOSO by the example of axial 8-stages jet engine compressor. Folomeev V., (Sarov Engineering Center) Iakunin A., (JSC Klimov) 1 Objectives To create the procedure
More informationExpress Introductory Training in ANSYS Fluent Workshop 04 Fluid Flow Around the NACA0012 Airfoil
Express Introductory Training in ANSYS Fluent Workshop 04 Fluid Flow Around the NACA0012 Airfoil Dimitrios Sofialidis Technical Manager, SimTec Ltd. Mechanical Engineer, PhD PRACE Autumn School 2013 -
More informationVerification and Validation of Turbulent Flow around a Clark-Y Airfoil
Verification and Validation of Turbulent Flow around a Clark-Y Airfoil 1. Purpose 58:160 Intermediate Mechanics of Fluids CFD LAB 2 By Tao Xing and Fred Stern IIHR-Hydroscience & Engineering The University
More informationAvailable online at ScienceDirect. Energy Procedia 45 (2014 )
Available online at www.sciencedirect.com ScienceDirect Energy Procedia 45 (2014 ) 131 140 68th Conference of the Italian Thermal Machines Engineering Association, ATI2013 2D CFD Modeling of H-Darrieus
More informationImpact of STAR-CCM+ v7.0 in the Automotive Industry Frederick J. Ross, CD-adapco Director, Ground Transportation
Impact of STAR-CCM+ v7.0 in the Automotive Industry Frederick J. Ross, CD-adapco Director, Ground Transportation Vehicle Simulation Components Vehicle Aerodynamics Design Studies Aeroacoustics Water/Dirt
More informationRecent Advances in Modelling Wind Parks in STAR CCM+ Steve Evans
Recent Advances in Modelling Wind Parks in STAR CCM+ Steve Evans Introduction Company STAR-CCM+ Agenda Wind engineering at CD-adapco STAR-CCM+ & EnviroWizard Developments for Offshore Simulation CD-adapco:
More informationPerformance improvement of a wind turbine blade using a developed inverse design method
energyequipsys/ Vol 4/No1/June 2016/ 1-10 Energy Equipment and Systems http://energyequipsys.ut.ac.ir www.energyeuquipsys.com Performance improvement of a wind turbine blade using a developed inverse design
More informationNUMERICAL 3D TRANSONIC FLOW SIMULATION OVER A WING
Review of the Air Force Academy No.3 (35)/2017 NUMERICAL 3D TRANSONIC FLOW SIMULATION OVER A WING Cvetelina VELKOVA Department of Technical Mechanics, Naval Academy Nikola Vaptsarov,Varna, Bulgaria (cvetelina.velkova1985@gmail.com)
More informationANSYS FLUENT. Airfoil Analysis and Tutorial
ANSYS FLUENT Airfoil Analysis and Tutorial ENGR083: Fluid Mechanics II Terry Yu 5/11/2017 Abstract The NACA 0012 airfoil was one of the earliest airfoils created. Its mathematically simple shape and age
More informationICMIEE D CFD Analysis of a Straight-bladed Vertical Axis Wind Turbine Using General Grid Interface Method
International Conference on Mechanical, Industrial and Energy Engineering 2018 23-24 December, 2018, Khulna, BANGLADESH ICMIEE18-319 2D CFD Analysis of a Straight-bladed Vertical Axis Wind Turbine Using
More informationAN EXPERIMENTAL STUDY AND SIMULATION WITH FLUENT
AN EXPERIMENTAL STUDY AND SIMULATION WITH FLUENT OF THE HORIZONTAL AXIS WIND TURBINE (HAWT) BLADE TOWER DYNAMIC INTERACTION V. P. CAMBANIS 1 & H. STAPOUNTZIS 2 Lab. of Fluid Mechanics & Turbomachinery,
More informationS-ducts and Nozzles: STAR-CCM+ at the Propulsion Aerodynamics Workshop. Peter Burns, CD-adapco
S-ducts and Nozzles: STAR-CCM+ at the Propulsion Aerodynamics Workshop Peter Burns, CD-adapco Background The Propulsion Aerodynamics Workshop (PAW) has been held twice PAW01: 2012 at the 48 th AIAA JPC
More informationDebojyoti Ghosh. Adviser: Dr. James Baeder Alfred Gessow Rotorcraft Center Department of Aerospace Engineering
Debojyoti Ghosh Adviser: Dr. James Baeder Alfred Gessow Rotorcraft Center Department of Aerospace Engineering To study the Dynamic Stalling of rotor blade cross-sections Unsteady Aerodynamics: Time varying
More informationDeveloping Tools for Assessing Bend-twist Coupled Foils
Developing Tools for Assessing Bend-twist Coupled Foils Laura Marimon Giovannetti, Joseph Banks, Stephen R. Turnock, Stephen W. Boyd, University of Southampton, Southampton/UK, L.Marimon-Giovannetti@soton.ac.uk
More informationOptimization of under-relaxation factors. and Courant numbers for the simulation of. sloshing in the oil pan of an automobile
Optimization of under-relaxation factors and Courant numbers for the simulation of sloshing in the oil pan of an automobile Swathi Satish*, Mani Prithiviraj and Sridhar Hari⁰ *National Institute of Technology,
More informationBest Practices: Volume Meshing Kynan Maley
Best Practices: Volume Meshing Kynan Maley Volume Meshing Volume meshing is the basic tool that allows the creation of the space discretization needed to solve most of the CAE equations for: CFD Stress
More informationNumerical Simulation Study on Aerodynamic Characteristics of the High Speed Train under Crosswind
2017 2nd International Conference on Industrial Aerodynamics (ICIA 2017) ISBN: 978-1-60595-481-3 Numerical Simulation Study on Aerodynamic Characteristics of the High Speed Train under Crosswind Fan Zhao,
More informationUnsteady Flow Simulation and Dynamic Stall Behaviour of Vertical Axis Wind Turbine Blades
WIND ENGINEERING VOLUME 35, NO. 4, 2011 PP 511-510 511 Unsteady Flow Simulation and Dynamic Stall Behaviour of Vertical Axis Wind Turbine Blades Ning Qin*, Robert Howell, Naveed Durrani, Kenichi Hamada
More informationComputational Fluid Dynamics Analysis of an Idealized Modern Wingsuit
Washington University in St. Louis Washington University Open Scholarship Mechanical Engineering and Materials Science Independent Study Mechanical Engineering & Materials Science 12-21-2016 Computational
More informationEstimating Vertical Drag on Helicopter Fuselage during Hovering
Estimating Vertical Drag on Helicopter Fuselage during Hovering A. A. Wahab * and M.Hafiz Ismail ** Aeronautical & Automotive Dept., Faculty of Mechanical Engineering, Universiti Teknologi Malaysia, 81310
More informationWONG HSI, J. J. MIAU,
Flow Separation Control with a Truncated Ellipse Airfoil in Cycling Aerodynamics WONG HSI, J. J. MIAU Department of Aeronautics and Astronautics (DAA), National Cheng Kung University, Tainan, Taiwan (R.O.C)
More informationAerodynamicCharacteristicsofaReal3DFlowaroundaFiniteWing
Global Journal of Researches in Engineering: D Chemical Engineering Volume 14 Issue 1 Version 1.0 Year 2014 Type: Double Blind Peer Reviewed International Research Journal Publisher: Global Journals Inc.
More informationComputational Fluid Dynamics Simulation of a Rim Driven Thruster
Computational Fluid Dynamics Simulation of a Rim Driven Thruster Aleksander J Dubas, N. W. Bressloff, H. Fangohr, S. M. Sharkh (University of Southampton) Abstract An electric rim driven thruster is a
More informationAxisymmetric Viscous Flow Modeling for Meridional Flow Calculation in Aerodynamic Design of Half-Ducted Blade Rows
Memoirs of the Faculty of Engineering, Kyushu University, Vol.67, No.4, December 2007 Axisymmetric Viscous Flow Modeling for Meridional Flow alculation in Aerodynamic Design of Half-Ducted Blade Rows by
More informationµ = Pa s m 3 The Reynolds number based on hydraulic diameter, D h = 2W h/(w + h) = 3.2 mm for the main inlet duct is = 359
Laminar Mixer Tutorial for STAR-CCM+ ME 448/548 March 30, 2014 Gerald Recktenwald gerry@pdx.edu 1 Overview Imagine that you are part of a team developing a medical diagnostic device. The device has a millimeter
More informationDesign and Dynamic Analysis of Wind Turbine Blade
Design and Dynamic Analysis of Wind Turbine Blade T.Krishnamurthy *, Y.Sesharao # PG Student, Department of Mechanical Engineering, QIS College of Engineering & Technology, Ongole, India * Professor, Department
More informationReproducibility of Complex Turbulent Flow Using Commercially-Available CFD Software
Reports of Research Institute for Applied Mechanics, Kyushu University No.150 (71 83) March 2016 Reproducibility of Complex Turbulent Flow Using Commercially-Available CFD Software Report 3: For the Case
More informationDYNAMICS OF A VORTEX RING AROUND A MAIN ROTOR HELICOPTER
DYNAMICS OF A VORTEX RING AROUND A MAIN ROTOR HELICOPTER Katarzyna Surmacz Instytut Lotnictwa Keywords: VORTEX RING STATE, HELICOPTER DESCENT, NUMERICAL ANALYSIS, FLOW VISUALIZATION Abstract The main goal
More informationCAD-BASED WORKFLOWS. VSP Workshop 2017
CAD-BASED WORKFLOWS VSP Workshop 2017 RESEARCH IN FLIGHT COMPANY Established 2012 Primary functions are the development, marketing and support of FlightStream and the development of aerodynamic solutions
More informationRecent & Upcoming Features in STAR-CCM+ for Aerospace Applications Deryl Snyder, Ph.D.
Recent & Upcoming Features in STAR-CCM+ for Aerospace Applications Deryl Snyder, Ph.D. Outline Introduction Aerospace Applications Summary New Capabilities for Aerospace Continuity Convergence Accelerator
More informationAPPROACH FOR NUMERICAL MODELING OF AIRFOIL DYNAMIC STALL
APPROACH FOR NUMERICAL MODELING OF AIRFOIL DYNAMIC STALL Cvetelina Velkova, Ivan Dobrev, Michael Todorov, Fawaz Massouh To cite this version: Cvetelina Velkova, Ivan Dobrev, Michael Todorov, Fawaz Massouh.
More informationTurbocharger Design & Analysis Solutions. Bill Holmes Brad Hutchinson Detroit, October 2012
Turbocharger Design & Analysis Solutions Bill Holmes Brad Hutchinson Detroit, October 2012 Agenda ANSYS overview ANSYS TurboSystem Blade row solutions The ANSYS Transformation methods An example: turbocharger
More informationResearch Article Aerodynamic Shape Optimization of a Vertical-Axis Wind Turbine Using Differential Evolution
International Scholarly Research Network ISRN Renewable Energy Volume 2012, Article ID 528418, 16 pages doi:10.5402/2012/528418 Research Article Aerodynamic Shape Optimization of a Vertical-Axis Wind Turbine
More informationSPC 307 Aerodynamics. Lecture 1. February 10, 2018
SPC 307 Aerodynamics Lecture 1 February 10, 2018 Sep. 18, 2016 1 Course Materials drahmednagib.com 2 COURSE OUTLINE Introduction to Aerodynamics Review on the Fundamentals of Fluid Mechanics Euler and
More informationAdjoint Solver Workshop
Adjoint Solver Workshop Why is an Adjoint Solver useful? Design and manufacture for better performance: e.g. airfoil, combustor, rotor blade, ducts, body shape, etc. by optimising a certain characteristic
More informationCFD Modeling of a Radiator Axial Fan for Air Flow Distribution
CFD Modeling of a Radiator Axial Fan for Air Flow Distribution S. Jain, and Y. Deshpande Abstract The fluid mechanics principle is used extensively in designing axial flow fans and their associated equipment.
More informationAerodynamic Design Optimization of UAV Rotor Blades using a Genetic Algorithm
Aerodynamic Design Optimization of UAV Rotor Blades using a Genetic Algorithm Hak-Min Lee 1), Nahm-Keon Hur 2) and *Oh-Joon Kwon 3) 1), 3) Department of Aerospace Engineering, KAIST, Daejeon 305-600, Korea
More informationEffect of Position of Wall Mounted Surface Protrusion in Drag Characteristics At Low Reynolds Number
ISSN (e): 2250 3005 Volume, 07 Issue, 11 November 2017 International Journal of Computational Engineering Research (IJCER) Effect of Position of Wall Mounted Surface Protrusion in Drag Characteristics
More informationMULTI-SCIENCE PUBLISHING COMPANY. Teymour Javaherchi, Sylvain Antheaume and Alberto Aliseda
Hierarchical Methodology for the Numerical Simulation of the Flow Field around and in the Wake of Horizontal Axis Wind Turbines: Rotating Reference Frame, Blade Element Method and Actuator Disk Model by
More informationSTAR-CCM+: Wind loading on buildings SPRING 2018
STAR-CCM+: Wind loading on buildings SPRING 2018 1. Notes on the software 2. Assigned exercise (submission via Blackboard; deadline: Thursday Week 3, 11 pm) 1. NOTES ON THE SOFTWARE STAR-CCM+ generates
More informationFLUID DYNAMICS ANALYSIS OF A COUNTER ROTATING DUCTED PROPELLER
FLUID DYNAMICS ANALYSIS OF A COUNTER ROTATING DUCTED PROPELLER Chao Xu, Cees Bil, Sherman CP. Cheung School of Aerospace, Mechanical and Manufacturing Engineering, RMIT University Keywords: Twin counter-rotating
More informationInvestigation of mixing chamber for experimental FGD reactor
Investigation of mixing chamber for experimental FGD reactor Jan Novosád 1,a, Petra Danová 1 and Tomáš Vít 1 1 Department of Power Engineering Equipment, Faculty of Mechanical Engineering, Technical University
More informationNUMERICAL SIMULATIONS OF FLOW THROUGH AN S-DUCT
NUMERICAL SIMULATIONS OF FLOW THROUGH AN S-DUCT 1 Pravin Peddiraju, 1 Arthur Papadopoulos, 2 Vangelis Skaperdas, 3 Linda Hedges 1 BETA CAE Systems USA, Inc., USA, 2 BETA CAE Systems SA, Greece, 3 CFD Consultant,
More informationSummary of the main PROBAND project results
Summary of the main PROBAND project results WP2: WP2 was dedicated to the development and validation broadband noise prediction methods. Once validated on non rotating airfoils in WP2, these methods were
More informationInternational Power, Electronics and Materials Engineering Conference (IPEMEC 2015)
International Power, Electronics and Materials Engineering Conference (IPEMEC 2015) Numerical Simulation of the Influence of Intake Grille Shape on the Aerodynamic Performance of a Passenger Car Longwei
More informationReproducibility of Complex Turbulent Flow Using Commercially-Available CFD Software
Reports of Research Institute for Applied Mechanics, Kyushu University, No.150 (60-70) March 2016 Reproducibility of Complex Turbulent Flow Using Commercially-Available CFD Software Report 2: For the Case
More informationSmall Height Duct Design for 17 Multicopter Fan Considering Its Interference on Quad-copter
Small Height Duct Design for 17 Multicopter Fan Considering Its Interference on Quad-copter Stremousov K.*, Arkhipov M.* **, Serokhvostov S.* ** * Moscow Institute of Physics and Technology, Department
More informationCFD MODELING FOR PNEUMATIC CONVEYING
CFD MODELING FOR PNEUMATIC CONVEYING Arvind Kumar 1, D.R. Kaushal 2, Navneet Kumar 3 1 Associate Professor YMCAUST, Faridabad 2 Associate Professor, IIT, Delhi 3 Research Scholar IIT, Delhi e-mail: arvindeem@yahoo.co.in
More information3D Aerodynamic Optimization of NREL VI Wind Turbine Blade for Increased Power Output and Visualization of Flow Characteristics
Dissertations and Theses Spring 2014 3D Aerodynamic Optimization of NREL VI Wind Turbine Blade for Increased Power Output and Visualization of Flow Characteristics Tsewang Rabga Shrestha Embry-Riddle Aeronautical
More informationOptimate CFD Evaluation Optimate Glider Optimization Case
Optimate CFD Evaluation Optimate Glider Optimization Case Authors: Nathan Richardson LMMFC CFD Lead 1 Purpose For design optimization, the gold standard would be to put in requirements and have algorithm
More informationVerification and Validation of Turbulent Flow around a Clark-Y Airfoil
1 Verification and Validation of Turbulent Flow around a Clark-Y Airfoil 1. Purpose ME:5160 Intermediate Mechanics of Fluids CFD LAB 2 (ANSYS 19.1; Last Updated: Aug. 7, 2018) By Timur Dogan, Michael Conger,
More informationComputational Simulation of the Wind-force on Metal Meshes
16 th Australasian Fluid Mechanics Conference Crown Plaza, Gold Coast, Australia 2-7 December 2007 Computational Simulation of the Wind-force on Metal Meshes Ahmad Sharifian & David R. Buttsworth Faculty
More informationResearch Article A Computational Investigation of Unsteady Aerodynamics of Insect-Inspired Fixed Wing Micro Aerial Vehicle s 2D Airfoil
Advances in Aerospace Engineering, Article ID 5449, 7 pages http://dx.doi.org/1.1155/214/5449 Research Article A Computational Investigation of Unsteady Aerodynamics of Insect-Inspired Fixed Wing Micro
More informationAdvances in Turbomachinery Simulation Fred Mendonça and material prepared by Chad Custer, Turbomachinery Technology Specialist
Advances in Turbomachinery Simulation Fred Mendonça and material prepared by Chad Custer, Turbomachinery Technology Specialist Usage From Across the Industry Outline Key Application Objectives Conjugate
More informationIntroduction to C omputational F luid Dynamics. D. Murrin
Introduction to C omputational F luid Dynamics D. Murrin Computational fluid dynamics (CFD) is the science of predicting fluid flow, heat transfer, mass transfer, chemical reactions, and related phenomena
More informationModeling External Compressible Flow
Tutorial 3. Modeling External Compressible Flow Introduction The purpose of this tutorial is to compute the turbulent flow past a transonic airfoil at a nonzero angle of attack. You will use the Spalart-Allmaras
More informationNumerical Analysis and Geometry Optimisation of Vertical Vane of Room Air-conditioner
Numerical Analysis and Geometry Optimisation of Vertical Vane of Room Air-conditioner Abdulkareem Sh. Mahdi Al-Obaidi 1,*, Chan Wei Yin 1, Felicia Wong Yen Myan 1 and Yan Yao Chen 1 1 School of Engineering,
More informationACTIVE SEPARATION CONTROL WITH LONGITUDINAL VORTICES GENERATED BY THREE TYPES OF JET ORIFICE SHAPE
24 TH INTERNATIONAL CONGRESS OF THE AERONAUTICAL SCIENCES ACTIVE SEPARATION CONTROL WITH LONGITUDINAL VORTICES GENERATED BY THREE TYPES OF JET ORIFICE SHAPE Hiroaki Hasegawa*, Makoto Fukagawa**, Kazuo
More informationDetached-Eddy Simulation of a Linear Compressor Cascade with Tip Gap and Moving Wall *)
FOI, Stockholm, Sweden 14-15 July, 2005 Detached-Eddy Simulation of a Linear Compressor Cascade with Tip Gap and Moving Wall *) A. Garbaruk,, M. Shur, M. Strelets, and A. Travin *) Study is carried out
More informationViscous/Potential Flow Coupling Study for Podded Propulsors
First International Symposium on Marine Propulsors smp 09, Trondheim, Norway, June 2009 Viscous/Potential Flow Coupling Study for Podded Propulsors Eren ÖZSU 1, Ali Can TAKİNACI 2, A.Yücel ODABAŞI 3 1
More informationThe Spalart Allmaras turbulence model
The Spalart Allmaras turbulence model The main equation The Spallart Allmaras turbulence model is a one equation model designed especially for aerospace applications; it solves a modelled transport equation
More informationMESH REQUIREMENT INVESTIGATION FOR 2D AND 3D AERODYNAMIC SIMULATION OF VERTICAL AXIS WIND TURBINES
MESH REQUIREMENT INVESTIGATION FOR 2D AND 3D AERODYNAMIC SIMULATION OF VERTICAL AXIS WIND TURBINES SAMAN NAGHIB ZADEH A Thesis In the Department of Mechanical and Industrial Engineering Presented in Partial
More informationCFD studies of a 10 MW turbine equipped with trailing edge flaps
CFD studies of a 10 MW turbine equipped with trailing edge flaps 10th EAWE PhD Seminar on Wind Energy in Europe 28-31 October 2014, Orléans, France Dipl.-Ing. Eva Jost e.jost@iag.uni-stuttgart.de Overview
More informationTeam 194: Aerodynamic Study of Airflow around an Airfoil in the EGI Cloud
Team 194: Aerodynamic Study of Airflow around an Airfoil in the EGI Cloud CFD Support s OpenFOAM and UberCloud Containers enable efficient, effective, and easy access and use of MEET THE TEAM End-User/CFD
More informationGrid Dependence Study of Transonic/Supersonic Flow Past NACA Air-foil using CFD Hemanth Kotaru, B.Tech (Civil Engineering)
Grid Dependence Study of Transonic/Supersonic Flow Past NACA Air-foil using CFD Hemanth Kotaru, B.Tech (Civil Engineering) Abstract Computational fluid dynamics is a relatively young field in engineering.
More informationSimulation of Turbulent Flow around an Airfoil
1. Purpose Simulation of Turbulent Flow around an Airfoil ENGR:2510 Mechanics of Fluids and Transfer Processes CFD Lab 2 (ANSYS 17.1; Last Updated: Nov. 7, 2016) By Timur Dogan, Michael Conger, Andrew
More informationEnhancement of wind turbine aerodynamic performance by a numerical optimization technique
Journal of Mechanical Science and Technology 26 (2) (202) 455~462 www.springerlink.com/content/738-494x DOI 0.007/s2206-0-035-2 Enhancement of wind turbine aerodynamic performance by a numerical optimization
More informationInteractive Fluid Dynamics Visualization
Interactive Fluid Dynamics Visualization Victor Mateevitsi 1, Andrew Johnson 2 Electronic Visualization Laboratory, University of Illinois at Chicago ABSTRACT In this paper we describe TurboPump, an interactive
More informationMSC Software Aeroelastic Tools. Mike Coleman and Fausto Gill di Vincenzo
MSC Software Aeroelastic Tools Mike Coleman and Fausto Gill di Vincenzo MSC Software Confidential 2 MSC Software Confidential 3 MSC Software Confidential 4 MSC Software Confidential 5 MSC Flightloads An
More informationCFD ANALYSIS Of COMBINED 8-12 STAGES Of INTERMIDIATE PRESSURE STEAM TURBINE
CFD ANALYSIS Of COMBINED 8-12 STAGES Of INTERMIDIATE PRESSURE STEAM TURBINE 1st Author name : SHIVAKUMAR VASMATE, 2nd Author name : KAMALADEVI ANANDE. 1 Department of Mechanical Engineering, India 2 Department
More informationPotsdam Propeller Test Case (PPTC)
Second International Symposium on Marine Propulsors smp 11, Hamburg, Germany, June 2011 Workshop: Propeller performance Potsdam Propeller Test Case (PPTC) Olof Klerebrant Klasson 1, Tobias Huuva 2 1 Core
More informationTo study Magnus Effect on Flettner Rotor
To study Magnus Effect on Flettner Rotor Mandar Gadkari 1, Varun Deshpande 2, Sumant Mahulkar 3, Vishal Khushalani 4, Shubham Pardhi 5, Dr. A.P. Kedar 6 1-5 (Final year B.E Mechanical Engineering Student,
More information