A CFD model for orbital gerotor motor
|
|
- Sophie Woods
- 5 years ago
- Views:
Transcription
1 IOP Conference Series: Earth and Environmental Science A CFD model for orbital gerotor motor To cite this article: H Ding et al 2012 IOP Conf. Ser.: Earth Environ. Sci View the article online for updates and enhancements. Related content - Cavitation simulation and NPSH prediction of a double suction centrifugal pump P Li, Y F Huang and J Li - Experimental study on the cavitation of vortex diode based on CFD L Jiao, P P Zhang, C N Chen et al. - Numerical study of cavitation flows inside a tubular pumping station X L Tang, W Huang, F J Wang et al. This content was downloaded from IP address on 14/09/2018 at 01:59
2 A CFD model for orbital gerotor motor H Ding 1, X J Lu 2 and B Jiang 3 1 Simerics Incorporated th Ave. NE Ste. A203, Bellevue, 98004, USA 2 Ningbo Zhongyi Hydraulic Motor Co., Ltd. 88 Zhongyi Road, Zhenhai Economic Development Zone, Ningbo, China 3 College of Mechanical Engineering, University of Shanghai for Science and Technology 516 Jun Gong Road, Shanghai, , China hd@simerics.com Abstract. In this paper, a full 3D transient CFD model for orbital gerotor motor is described in detail. One of the key technologies to model such a fluid machine is the mesh treatment for the dynamically changing rotor fluid volume. Based on the geometry and the working mechanism of the orbital gerotor, a moving/deforming mesh algorithm was introduced and implemented in a CFD software package. The test simulations show that the proposed algorithm is accurate, robust, and efficient when applied to industrial orbital gerotor motor designs. Simulation results are presented in the paper and compared with experiment test data. 1. Introduction A gerotor is a positive displacement machine which has an inner gear and an outer gear. For a normal gerotor machine, the inner gear, which is the drive gear, and the driven outer gear rotate around their own fixed centers during operation. Due to their compact design, low cost, and robustness, normal gerotor pumps are widely used in many industrial applications. There is an alternative design, the orbital gerotor, in which the outer gear is stationary, while the inner gear rotates around an orbiting center [1]. The orbital gerotor can be used as a motor to obtain high torque output at low rotation speed with small dimension. In this design, typically a rotating flow distributor is used to maintain proper timing connecting the inlet and the outlet ports to the rotor. CFD models of normal gerotor pumps have been used to improve gerotor designs in many engineering applications for the last decades. In 1997, Jiang and Perng [2] created the first full 3D transient CFD model for a gerotor pump and included a cavitation model. Their model successfully predicted gerotor pump volumetric efficiency loses due to cavitation. Kini et al. [3] coupled CFD simulation with a structural solver to determine deflection of the cover plate in the pump assembly due to variation in internal pressure profiles during operation. Zhang et al. [4] studied the effects of the inlet pressure, tip clearance, porting and the metering groove geometry on pump flow performances and pressure ripples using CFD model. Natchimuthu et al. [5], Ruvalcaba et al. [6] also used CFD to analyze gerotor oil pump flow patterns. Jiang et al. [7] created a 3D CFD model for crescent pumps, a variation of gerotor pumps with a crescent shaped island between the inner and outer gears. In comparison, CFD studies of orbital type of gerotor are rare. Authors of this paper have not found any full 3D CFD model for this type of gerotor in the literature. Because of the difference in motion mechanism, traditional gerotor model cannot be applied directly to orbital gerotor. Modifications in Published under licence by Ltd 1
3 moving/deforming mesh algorithm as well as modifications in surface velocity assignment, torque and power calculations are necessary. Orbital gerotors are commonly used as motors which have much higher pressure differences and even smaller fluid gaps as compared with normal gerotor pumps. Those two conditions impose big challenges for the flow solver. That could be one of the main reasons why CFD analysis for orbital gerotors is not very popular. 2. Orbital Gerotor Motor Configuration and Simulation Strategy 2.1. Working Principle of an Orbital Gerotor Motor As shown in Figure 1, an orbital gerotor motor has a stationary outer gear and a rotating inner gear. Inner gear has 1 less tooth than the outer gear. During operation, the inner gear rotates and rolls over the outer gear teeth. During the movement, the inner gear center also rotates around the outer gear center in the opposite direction. Each time when the inner gear advances one tooth, the inner gear center already rotates a complete revolution. Therefore the rotation speed of the center is NT in times that of the inner gear rotation speed, where NT in is the number of inner gear teeth. Figure 1.1 to Figure 1.10 show the sequence of gear motion for one complete revolution of the inner gear center
4 Figure 1. Orbital gerotor motor Each cavity between neighboring outer gear teeth, bounded by the inner gear surface, forms a fluid pocket. During the operation, those fluid pockets change shape and volume. When the volume increases, it will draw in fluid. When the volume decreases, it will drive the fluid out. Combined with proper connections with the inlet and the outlet ports, those dynamically changing pockets will move the fluid from the inlet to the outlet while at the same time outputting torque and power to the shaft. Figure 2 shows the complete shape change sequences of one of the pockets when the inner gear advances one tooth over the outer gear. The plots 2.1 to 2.5 show the sequences of the expansion half cycle, and 2.6 to 2.10 show the compression half cycle. Unlike a normal gerotor where the fluid pockets are rotating and the inlet and outlet ports are stationary, for orbiting gerotor, those fluid pockets stay in the same location during the operation. In order to provide proper timing for the connections with the inlet and the outlet, typically there is a rotating distributor to create dynamic bridges between the ports and the rotor. The purpose of the distributor is to connect each pocket to the high pressure inlet during its expansion half cycle, and to the low pressure outlet during its compression half cycle. Typically, the flow distributor rotates at the same speed as the inner gear. Extra caution needs to be taken when creating fluid volumes for the flow distributor and the rotor. It is important to make sure that the initial relative position between the inner gear and the distributor is accurate, otherwise the motor system may not work as expected Figure 2. Shape and volume change sequence of one fluid pocket 2.2. Instant Center of Rotation Since the inner gear of an orbiting gerotor does not have a fixed rotation axis, calculating the hydraulic torque applied to the inner gear becomes an issue. One way to resolve this issue is to find the instantaneous center of rotation of the inner gear. For a body undergoing planar movement, the instantaneous center of rotation (ICOR) is the point where the velocity is zero at a particular instance of time. At that instance, the body is doing a pure rotation around the ICOR. If the ICOR is known, the hydraulic torque can be calculated as the torque against the ICOR at that moment. 3
5 Figure 3. Instant center of rotation ICOR of an orbital gerotor inner gear can be found by checking the velocity distribution on the inner rotor. As shown in Figure 4, all the points on the inner gear undergo a composite motion: a) translation with the motion of the gear center, and b) rotation around the gear center with speed in. The inner gear center itself rotates around the outer gear center with the speed of c. As mentioned previously, the relationship between the two rotation speeds is: As shown in figure 4, we can always draw a line (line of symmetry) connecting the inner gear center and the outer gear center at any moment of time. Defining a right-hand coordinate system with the origin at the inner gear center, the y axis along the symmetry line, and the x axis in a direction perpendicular to the y axis enables the velocity of the inner gear center in x and y directions to be defined as: where Ec is the eccentricity of the inner gear, or the distance between the inner gear center and the outer gear center. For any point on inner gear with coordinates (x, y), the velocity components for rotation around the inner gear center are; and the combined velocities are: (1) (2) (3) (4) (5) (6) (7) 4
6 From equation (6) and (7), it is clear that at the point (0, ), both velocity components equal zero. Therefore, that point corresponds to the coordinates of the instant center of rotation. Since the line of symmetry rotates around the outer gear center at the speed of c, it is very straight forward to calculate ICOR during the simulation Mesh Solution Similarly, the motion of the inner gear boundary can be determined through the composite motion of the rotation around the inner gear center plus the translation of the inner gear center. The shape of the fluid volume for the rotor is then properly defined. Meshing of moving/deforming fluid domains in a positive displacement (PD) fluid machine is always very challenging. As a typical PD machine, gerotor motor has many dynamic fluid gaps with very small clearances, down to several microns. Those gaps have a strong influence on machine s performance including flow leakage and volumetric efficiency, flow and pressure ripple, pressure lock, cavitation and erosion, and torque and power. Therefore they have to be modeled accurately. Many generic moving mesh solutions, for example the immersed boundary method, have difficulties in modeling such dynamic gaps. So far, the most successful solution for creating a gerotor rotor mesh is the structured moving/sliding mesh approach commonly used in normal gerotor pump simulations (Jiang and Perng [2]). This approach is also adapted in this study. In the structured moving/sliding mesh approach, the fluid volume of the rotor chamber is separated from the other parts of the fluid domain. Topologically, the rotor volume is similar to a ring, and an initial structured mesh can be easily created for that kind of shape. The rotor mesh will be connected to other fluid volumes through sliding interfaces. When the inner gear surface moves to a new position, the mesh on the surface of the inner gear does not simply move with the inner gear surface. Instead, the mesh slides on the inner gear surface while make the necessary adjustments to conform to the new clearance between the inner gear surface and the outer gear surface. Simultaneously, the interface connections between the rotor volume and other fluid volumes are updated. Figure 3 shows a typical structured mesh for a gerotor rotor volume. Figure 4. Gerotor rotor structured mesh 2.4. Implementation The proposed orbital gerotor model was implemented in the commercial CFD package PumpLinx as a new template. A template in PumpLinx provides two main functionalities: 1) It creates the initial rotor mesh, and controls mesh moving /deformation of the rotor and other dynamic fluid volumes during the simulation; and 2) It provides special setup and post processing options for that specific 5
7 fluid machine. With the help of the template, user can setup a complete orbital gerotor motor in less than 30 minutes starting from proper CAD geometry output. One can refer to Ding et al. [8] for a more detailed description of the software. 3. CFD Solver and Governing Equations The CFD package used in this study solves conservation equations of mass and momentum using a finite volume approach. Those conservation laws can be written in integral representation as (8) (9) The standard k two-equation model (Launder & Spalding [9]) is used to account for turbulence, (10) (11) The cavitation model included in the software describes the cavitation vapor distribution using the following formulation (Singhal et al., [10]) (12) where is the diffusivity of the vapor mass fraction and f is the turbulent Schmidt number. The effects of liquid vapor, non-condensable gas (typically air), and liquid compressibility are all accounted for in the model. The final density calculation for the mixture is done by This software package has been successfully used in CFD simulations for many different types of positive displacement machines including: swash plate piston pump [11], gerotor pump [8], external gear pump [12], crescent pump [7], and variable displacement vane pump [13]. 4. Gerotor Motor Test Case An industrial orbital gerotor motor was used to demonstrate the proposed CFD model. Figure 5 is the solid model of the motor. This motor has two ports, port A and port B. The inner gear and flow distributor can also rotate in both directions without mechanical adjustment. The flow and rotation directions are determined by which port is connected to the high pressure fluid and which port is connected to the low pressure fluid. The one connected to the high pressure fluid becomes the inlet and the rotation direction will also change accordingly. (13) 6
8 Figure 5. Solid model of an orbital gerotor motor The fluid domain was subtracted from CAD geometry and divided into several volumes and meshed separately (Figure 6). Except for the rotor part which was created with structured mesh, all other fluid volumes were meshed with unstructured binary tree mesh. The special moving/sliding mesh of rotor volume and the rotation of flow distributor volume were automatically processed by the template, and the rest of the fluid volumes stayed stationary during the simulation. Those independent volumes were connected through sliding interfaces during simulation. A total of 360,000 cells was used in this model. Figure 6. Fluid volumes with mesh The working fluid used in the model is the high performance anti-wear hydraulic fluid HM46. The properties of HM46 are listed in Table 1. Determined based on the information provided by motor manufacturer, operating conditions used in simulation are also listed in table 1. 7
9 Table 1. Fluid properties and operating conditions Density (kg/m 3 ) 879 Viscosity (PaS) 0.04 Rotation speed (RPM) 100 Inlet pressure (MPa) 1 Outlet pressure (MPa) Simulation Results and Discussion Figure 7 shows the pressure distribution of high pressure inlet, low pressure outlet, and the flow distributor. The magenta color indicates high pressure and the blue color indicates low pressure, with an overall pressure range from 0 to 18 MPa. Figure 7. Pressure distribution on inlet/outlet ports and flow distributor The flow distributor for this motor has a total of 16 shoe shaped connectors to be connected to the rotor fluid pockets. Eight of the connectors connect to the low pressure outlet, and the other eight connect to the high pressure inlet. The connectors are arranged alternately and rotate at the same speed as the inner gear to create the proper timing of the connections. Figure 8 shows the simulation results at 4 different moments. In the picture, surfaces are colored by pressure with red representing high pressure, and blue representing low pressure, with an overall range from 0 to 20 MPa. Small spheres in those pictures are massless particles used to visualize the flow field. The white lines extruding from the particles show the direction and magnitude of the velocity of each particle. One can see that the red particles, coming from the high pressure inlet, are drawn into the rotor. And the blue particles, after the pockets connect to the low pressure port, are driven away from the rotor towards the outlet. 8
10 Figure 8. Pressure distribution and particle tracing Figures 9 to 12 plot the time history of the pressure in one of the fluid pocket; the mass flow rate; the power applied to the inner gear, and the torque applied to the inner gear. These curves correspond to a 100 RPM rotation speed for one complete revolution of the inner gear. The horizontal axis for these plots is the rotation angle of the inner gear. Figure 9. Pressure in a fluid pocket Figure 10. Mass flow rate The plots show that the solution has a clear periodical pattern except in the first couple of time steps. The pattern repeats itself every time the inner gear advances one tooth. This means that, under the current simulation conditions, one only needs to solve 2 to 3 inner gear teeth rotation, or 90 to 135 degree of the inner gear rotation, to have a complete set of flow characteristics of the motor. The transient simulation time to model one gear tooth rotation for these simulation conditions is about 35 minutes on a quad-core single CPU 2.2GHZ I7 2720QM Laptop Computer. 9
11 Figure 11. Hydraulic power Figure 12. Torque Experimental test samples provided by the manufacturer have rotational speeds ranging from 103 to 117RPM, and pressure differences ranging from 15 to 17 MPa. For this type of motor, the flow rate is a linear function of the rotation speed, and the torque is a linear function of the pressure difference. In order to have a fair comparison, the test flow rates are linearly converted to 100 RPM, and the test torques are linearly converted to15 MPa pressure difference. The converted volume flow rate and output torque of 41 test samples are plotted in figure 13 and 14 against the CFD simulation results. The horizontal axis of the two plots is test sample number. The plots show that the CFD flow rate prediction matches very well with the test data. The predicted torque is about 12% higher than the test results. Since torque measured in the experiment is the final output torque from the motor, it has mechanical and friction loses that are not accounted for in CFD results. This could be the main reason for the discrepancy in CFD torque prediction. Figure 13. Comparison of predicted and test flow Figure 14. Comparison of predicted and test rate torque Figures 15 and 16 plot the flow rate and power vs. rotation speed respectively. As expected, both the flow rate and the power are linearly increasing with the rotation speed. 10
12 Figure 15. Flow rate vs. rotation speed Figure 16. Power vs. rotation speed Figure 17 plots the torque vs. the rotational speed. From this plot, one can see that the torque of orbital gerotor motor is not a strong function of rotational speed. However the torque does decrease slightly when the rotational speed increases. Figure 17. Torque vs. rotation speed 6. Conclusions By analyzing the working mechanism of orbital gerotor motors, a CFD model for such fluid machine was developed and implemented as a new template in the CFD software PumpLinx. Simulation for a production motor shows that the present computational model is accurate and efficient. It s also found that the flow solver used in the current study is very robust in handling very high mesh aspect ratios and very small dynamic leakage gaps. With the demonstrated speed, robustness, and accuracy, this model can be used as a high fidelity design tool in the design process or as a diagnosis tool for orbital gerotor motors. Nomenclature c Inner gear center C 1 Turbulence model constant C 2 Turbulence model constant C c Cavitation model constant C e Cavitation model constant C Turbulence model constant D f Diffusivity of vapor mass fraction Ec Inner gear eccentricity f Body force (N) f v Vapor mass fraction t S' ij U u u' v v' vx, vy x, y Time Strain tensor Initial velocity Velocity component (m/s) Component of v' Velocity vector Turbulent fluctuation velocity Velocity in x, y direction Coordinates Turbulence dissipation 11
13 f g G t ICOR in k L M NT n p Q R c R e RPM Non-condensable gas mass fraction Turbulent generation term Instant center of rotation Inner gear Turbulence kinetic energy Length Mass flow rate (Kg/s) Number of gear teeth Surface normal Pressure (Pa) Flow rate (m 3 /h) Vapor condensation rate Vapor generation rate Revolution per minute t g l v k l f Fluid viscosity (Pa-s) Turbulent viscosity (Pa-s) Fluid density (kg/m 3 ) Gas density (kg/m 3 ) Liquid density (kg/m 3 ) Vapor density (kg/m 3 ) Surface of control volume Turbulence model constant Surface tension Turbulence model constant Turbulent Schmidt number Stress tensor Control volume Rotation speed References [1] Ivantysyn J and Ivantysnova M 2003 Hydrostatic Pumps and Motors (New Delhi : Tech Books International) [2] Jiang Y and Perng C 1997 An Efficient 3D Transient Computational Model for Vane Oil Pump and Gerotor Oil Pump Simulations SAE Technical Paper [3] Kini S, Mapara N, Thoms R and Chang P 2005 Numerical Simulation of Cover Plate Deflection in the Gerotor Pump SAE Technical Paper [4] Zhang D, Perng C and Laverty M 2006 Gerotor Oil Pump Performance and Flow/Pressure Ripple Study SAE Technical Paper [5] Natchimuthu K, Sureshkumar J and Ganesan V 2010 CFD Analysis of Flow through a Gerotor Oil Pump SAE Technical Paper [6] Ruvalcaba M A and Hu X Gerotor Fuel Pump Performance and Leakage Study ASME 2011 Int. Mechanical Engineering Congress & Exposition (Denver, Colorado, USA, 2011) [7] Jiang Y, Furmanczyk M, Lowry S and Zhang D et al A Three-Dimensional Design Tool for Crescent Oil Pumps SAE Technical Paper [8] Ding H, Visser F C, Jiang Y and Furmanczyk M 2011 J. Fluids Eng. Trans ASME 133(1) [9] Launder B E and Spalding D B 1974 Comput. Methods Appl. Mech. Eng [10] Singhal A K, Athavale M M, Li H Y and Jiang Y 2002 J. Fluids Eng. Trans ASME 124(3) [11] Meincke O and Rahmfeld R th Int. Fluid Power Conf. (Dresden, 1-2 April 2008) [12] Heisler A, Moskwa J and Fronczak F 2009 The Design of Low-Inertia, High-Speed External Gear Pump/Motors for Hydrostatic Dynamometer Systems SAE Technical Paper [13] Wang D, Ding H, Jiang Y and Xiang X 2012 Numerical Modeling of Vane Oil Pump with Variable Displacement SAE Technical Paper
Thank you for downloading one of our ANSYS whitepapers we hope you enjoy it.
Thank you! Thank you for downloading one of our ANSYS whitepapers we hope you enjoy it. Have questions? Need more information? Please don t hesitate to contact us! We have plenty more where this came from.
More informationFluid Structure Interaction Modeling for Geroler Motor Performance Prediction using FEA and CFD Coupled Approach
flotek.g 2017- Innovative Solutions in Flow Measurement and Control - Oil, Water and Gas August 28-30, 2017, FCRI, Palakkad, Kerala, India Fluid Structure Interaction Modeling for Geroler Motor Performance
More informationCFD Simulation of Cavitation in an Internal Gear Pump
CFD Simulation of Cavitation in an Internal Gear Pump Dr. Andreas Spille-Kohoff Jan Hesse CFX Berlin Software GmbH Berlin andreas.spille@cfx-berlin.de Contents Introduction Geometry and mesh Simulation
More information1 Introduction. Myung Sik Kim 1, Won Jee Chung 1, Jun Ho Jang 1, Chang Doo Jung 1 1 School of Mechatronics, Changwon National University, South Korea
Application of SolidWorks & AMESim - based Simulation Technique to Modeling, Cavitation, and Backflow Analyses of Trochoid Hydraulic Pump for Multi-step Transmission Myung Sik Kim 1, Won Jee Chung 1, Jun
More informationNon-Newtonian Transitional Flow in an Eccentric Annulus
Tutorial 8. Non-Newtonian Transitional Flow in an Eccentric Annulus Introduction The purpose of this tutorial is to illustrate the setup and solution of a 3D, turbulent flow of a non-newtonian fluid. Turbulent
More informationCo-Simulation von Flownex und ANSYS CFX am Beispiel einer Verdrängermaschine
Co-Simulation von Flownex und ANSYS CFX am Beispiel einer Verdrängermaschine Benoit Bosc-Bierne, Dr. Andreas Spille-Kohoff, Farai Hetze CFX Berlin Software GmbH, Berlin Contents Positive displacement compressors
More informationWebinar: TwinMesh for Reliable CFD Analysis of Rotating Positive Displacement Machines
Webinar: TwinMesh for Reliable CFD Analysis of Rotating Positive Displacement Machines 14.07.2015 Dipl.-Ing. Jan Hesse Jan.hesse@cfx-berlin.de CFX Berlin Software GmbH Karl-Marx-Allee 90 A 10243 Berlin
More informationCFD Simulation of a dry Scroll Vacuum Pump including Leakage Flows
CFD Simulation of a dry Scroll Vacuum Pump including Leakage Flows Jan Hesse, Rainer Andres CFX Berlin Software GmbH, Berlin, Germany 1 Introduction Numerical simulation results of a dry scroll vacuum
More informationCalculate a solution using the pressure-based coupled solver.
Tutorial 19. Modeling Cavitation Introduction This tutorial examines the pressure-driven cavitating flow of water through a sharpedged orifice. This is a typical configuration in fuel injectors, and brings
More informationCFD Simulation of a Dry Scroll Vacuum Pump Including Leakage Flows
Purdue University Purdue e-pubs International Compressor Engineering Conference School of Mechanical Engineering 2016 CFD Simulation of a Dry Scroll Vacuum Pump Including Leakage Flows Jan Hesse CFX Berlin
More informationUse of CFD in Design and Development of R404A Reciprocating Compressor
Purdue University Purdue e-pubs International Compressor Engineering Conference School of Mechanical Engineering 2006 Use of CFD in Design and Development of R404A Reciprocating Compressor Yogesh V. Birari
More informationCFD MODELING FOR PNEUMATIC CONVEYING
CFD MODELING FOR PNEUMATIC CONVEYING Arvind Kumar 1, D.R. Kaushal 2, Navneet Kumar 3 1 Associate Professor YMCAUST, Faridabad 2 Associate Professor, IIT, Delhi 3 Research Scholar IIT, Delhi e-mail: arvindeem@yahoo.co.in
More informationPump Modeler Template Documentation
Pump Modeler Template Documentation 2015 SAS IP, Inc. All rights reserved. Unauthorized use, distribution or duplication is prohibited CONTENTS USER INTERFACE AND WORKFLOW... 4 STEP 1: IMPORT GEOMETRY...
More informationApplication of SolidWorks & AMESim based Updated Simulation Technique to Back-flow Analysis of Trochoid Hydraulic Pump for Lubrication
Application of SolidWorks & AMESim based Updated Simulation Technique to Back-flow Analysis of Trochoid Hydraulic Pump for Lubrication Seung Won Jeong #, Won Jee Chung #, Man Su Kim #, Myung Sik Kim* #
More informationDesign optimization method for Francis turbine
IOP Conference Series: Earth and Environmental Science OPEN ACCESS Design optimization method for Francis turbine To cite this article: H Kawajiri et al 2014 IOP Conf. Ser.: Earth Environ. Sci. 22 012026
More informationUsing a Single Rotating Reference Frame
Tutorial 9. Using a Single Rotating Reference Frame Introduction This tutorial considers the flow within a 2D, axisymmetric, co-rotating disk cavity system. Understanding the behavior of such flows is
More informationDigital Design for Centrifugal Fans
Digital Design for Centrifugal Fans John Abbitt, Sam Lowry Department of Mechanical & Aerospace Engineering, University of Florida / Simerics, Inc. Abstract An objective in the curriculum in the Department
More informationOffshore Platform Fluid Structure Interaction (FSI) Simulation
Offshore Platform Fluid Structure Interaction (FSI) Simulation Ali Marzaban, CD-adapco Murthy Lakshmiraju, CD-adapco Nigel Richardson, CD-adapco Mike Henneke, CD-adapco Guangyu Wu, Chevron Pedro M. Vargas,
More informationCFD Modeling of a Radiator Axial Fan for Air Flow Distribution
CFD Modeling of a Radiator Axial Fan for Air Flow Distribution S. Jain, and Y. Deshpande Abstract The fluid mechanics principle is used extensively in designing axial flow fans and their associated equipment.
More informationComputational Modeling of the Three-Dimensional Flow in a Metallic Stator Progressing Cavity Pump
Computational Modeling of the Three-Dimensional Flow in a Metallic Stator Progressing Cavity Pump Emilio E. Paladino; João A. Lima and Rairam F. Almeida UFRN / DEM / PPGEM, Brazil Benno W. Assmann PETROBRAS
More informationAir Assisted Atomization in Spiral Type Nozzles
ILASS Americas, 25 th Annual Conference on Liquid Atomization and Spray Systems, Pittsburgh, PA, May 2013 Air Assisted Atomization in Spiral Type Nozzles W. Kalata *, K. J. Brown, and R. J. Schick Spray
More informationCOMPUTATIONAL FLUID DYNAMICS ANALYSIS OF ORIFICE PLATE METERING SITUATIONS UNDER ABNORMAL CONFIGURATIONS
COMPUTATIONAL FLUID DYNAMICS ANALYSIS OF ORIFICE PLATE METERING SITUATIONS UNDER ABNORMAL CONFIGURATIONS Dr W. Malalasekera Version 3.0 August 2013 1 COMPUTATIONAL FLUID DYNAMICS ANALYSIS OF ORIFICE PLATE
More informationOptimization of Hydraulic Fluid Parameters in Automotive Torque Converters
Optimization of Hydraulic Fluid Parameters in Automotive Torque Converters S. Venkateswaran, and C. Mallika Parveen Abstract The fluid flow and the properties of the hydraulic fluid inside a torque converter
More informationAn Introduction to SolidWorks Flow Simulation 2010
An Introduction to SolidWorks Flow Simulation 2010 John E. Matsson, Ph.D. SDC PUBLICATIONS www.sdcpublications.com Schroff Development Corporation Chapter 2 Flat Plate Boundary Layer Objectives Creating
More informationEffect of suction pipe leaning angle and water level on the internal flow of pump sump
IOP Conference Series: Earth and Environmental Science PAPER OPEN ACCESS Effect of suction pipe leaning angle and water level on the internal flow of pump sump To cite this article: Z-M Chen et al 216
More informationSimulation of Flow Development in a Pipe
Tutorial 4. Simulation of Flow Development in a Pipe Introduction The purpose of this tutorial is to illustrate the setup and solution of a 3D turbulent fluid flow in a pipe. The pipe networks are common
More informationUsing the Eulerian Multiphase Model for Granular Flow
Tutorial 21. Using the Eulerian Multiphase Model for Granular Flow Introduction Mixing tanks are used to maintain solid particles or droplets of heavy fluids in suspension. Mixing may be required to enhance
More informationIntroduction to ANSYS CFX
Workshop 03 Fluid flow around the NACA0012 Airfoil 16.0 Release Introduction to ANSYS CFX 2015 ANSYS, Inc. March 13, 2015 1 Release 16.0 Workshop Description: The flow simulated is an external aerodynamics
More informationSimulating Sinkage & Trim for Planing Boat Hulls. A Fluent Dynamic Mesh 6DOF Tutorial
Simulating Sinkage & Trim for Planing Boat Hulls A Fluent Dynamic Mesh 6DOF Tutorial 1 Introduction Workshop Description This workshop describes how to perform a transient 2DOF simulation of a planing
More informationComparison of Classic and Finned Piston Reciprocating Linear Air Compressor Using COMSOL Multiphysics
Comparison of Classic and Finned Piston Reciprocating Linear Air Compressor Using COMSOL Multiphysics M. Heidari*, P. Barrade, and A. Rufer LEI, École Polytechnique Fédérale de Lausanne, Lausanne, Switzerland
More informationUsing Multiple Rotating Reference Frames
Tutorial 9. Using Multiple Rotating Reference Frames Introduction Many engineering problems involve rotating flow domains. One example is the centrifugal blower unit that is typically used in automotive
More informationSolidWorks Flow Simulation 2014
An Introduction to SolidWorks Flow Simulation 2014 John E. Matsson, Ph.D. SDC PUBLICATIONS Better Textbooks. Lower Prices. www.sdcpublications.com Powered by TCPDF (www.tcpdf.org) Visit the following websites
More informationSimulation of Turbulent Flow over the Ahmed Body
Simulation of Turbulent Flow over the Ahmed Body 58:160 Intermediate Mechanics of Fluids CFD LAB 4 By Timur K. Dogan, Michael Conger, Maysam Mousaviraad, and Fred Stern IIHR-Hydroscience & Engineering
More informationTurbulencja w mikrokanale i jej wpływ na proces emulsyfikacji
Polish Academy of Sciences Institute of Fundamental Technological Research Turbulencja w mikrokanale i jej wpływ na proces emulsyfikacji S. Błoński, P.Korczyk, T.A. Kowalewski PRESENTATION OUTLINE 0 Introduction
More informationDESIGN AND OPTIMIZATION OF ROTARY TURRET PLATE OF POUCHER MACHINE
DESIGN AND OPTIMIZATION OF ROTARY TURRET PLATE OF POUCHER MACHINE Jigar G. Patel Institute of Technology, Nirma University, Ahmedabad 382481, India Email:14mmcc17@nirmuni.ac.in Mitesh B. Panchal Mechanical
More informationCFD grid generation and analysis of screw compressor with variable geometry rotors
CFD grid generation and analysis of screw compressor with variable geometry rotors S Rane, A Kovacevic, N Stosic, M Kethidi City University London, Centre for Positive Displacement Compressor Technology,
More informationANALYSIS AND OPTIMIZATION OF FLYWHEEL
Int. J. Mech. Eng. & Rob. Res. 2012 Sushama G Bawane et al., 2012 Research Paper ISSN 2278 0149 www.ijmerr.com Vol. 1, No. 2, July 2012 2012 IJMERR. All Rights Reserved ANALYSIS AND OPTIMIZATION OF FLYWHEEL
More informationA Comparative CFD Analysis of a Journal Bearing with a Microgroove on the Shaft & Journal
Proceedings of International Conference on Innovation & Research in Technology for Sustainable Development (ICIRT 2012), 01-03 November 2012 182 A Comparative CFD Analysis of a Journal Bearing with a Microgroove
More informationModeling Evaporating Liquid Spray
Tutorial 16. Modeling Evaporating Liquid Spray Introduction In this tutorial, FLUENT s air-blast atomizer model is used to predict the behavior of an evaporating methanol spray. Initially, the air flow
More informationTHE EFFECTS OF THE PLANFORM SHAPE ON DRAG POLAR CURVES OF WINGS: FLUID-STRUCTURE INTERACTION ANALYSES RESULTS
March 18-20, 2013 THE EFFECTS OF THE PLANFORM SHAPE ON DRAG POLAR CURVES OF WINGS: FLUID-STRUCTURE INTERACTION ANALYSES RESULTS Authors: M.R. Chiarelli, M. Ciabattari, M. Cagnoni, G. Lombardi Speaker:
More informationModeling Evaporating Liquid Spray
Tutorial 17. Modeling Evaporating Liquid Spray Introduction In this tutorial, the air-blast atomizer model in ANSYS FLUENT is used to predict the behavior of an evaporating methanol spray. Initially, the
More informationAutomotive Fluid-Structure Interaction (FSI) Concepts, Solutions and Applications. Laz Foley, ANSYS Inc.
Automotive Fluid-Structure Interaction (FSI) Concepts, Solutions and Applications Laz Foley, ANSYS Inc. Outline FSI Classifications FSI Solutions FSI Modeling Approaches ANSYS Workbench for FSI System
More informationComputer Life (CPL) ISSN: Fluid-structure Coupling Simulation Analysis of Wavy Lip Seals
Computer Life (CPL) ISSN: 1819-4818 Delivering Quality Science to the World Fluid-structure Coupling Simulation Analysis of Wavy Lip Seals Linghao Song a, Renpu Deng b and Chaonan Huang c College of Mechanical
More informationManipulator Dynamics: Two Degrees-of-freedom
Manipulator Dynamics: Two Degrees-of-freedom 2018 Max Donath Manipulator Dynamics Objective: Calculate the torques necessary to overcome dynamic effects Consider 2 dimensional example Based on Lagrangian
More informationCoupled Analysis of FSI
Coupled Analysis of FSI Qin Yin Fan Oct. 11, 2008 Important Key Words Fluid Structure Interface = FSI Computational Fluid Dynamics = CFD Pressure Displacement Analysis = PDA Thermal Stress Analysis = TSA
More informationInvestigation of mixing chamber for experimental FGD reactor
Investigation of mixing chamber for experimental FGD reactor Jan Novosád 1,a, Petra Danová 1 and Tomáš Vít 1 1 Department of Power Engineering Equipment, Faculty of Mechanical Engineering, Technical University
More informationUsing Multiple Rotating Reference Frames
Tutorial 10. Using Multiple Rotating Reference Frames Introduction Many engineering problems involve rotating flow domains. One example is the centrifugal blower unit that is typically used in automotive
More informationSIMULATION OF FLOW FIELD AROUND AND INSIDE SCOUR PROTECTION WITH PHYSICAL AND REALISTIC PARTICLE CONFIGURATIONS
XIX International Conference on Water Resources CMWR 2012 University of Illinois at Urbana-Champaign June 17-22, 2012 SIMULATION OF FLOW FIELD AROUND AND INSIDE SCOUR PROTECTION WITH PHYSICAL AND REALISTIC
More informationCFD Analysis of a Fully Developed Turbulent Flow in a Pipe with a Constriction and an Obstacle
CFD Analysis of a Fully Developed Turbulent Flow in a Pipe with a Constriction and an Obstacle C, Diyoke Mechanical Engineering Department Enugu State University of Science & Tech. Enugu, Nigeria U, Ngwaka
More informationRecent applications of overset mesh technology in SC/Tetra
Recent applications of overset mesh technology in SC/Tetra NIA CFD Seminar October 6, 2014 Tomohiro Irie Software Cradle Co., Ltd. 1 Contents Introduction Software Cradle SC/Tetra Background of Demands
More informationReliability - Based Robust Design Optimization of Centrifugal Pump Impeller for Performance Improvement considering Uncertainties in Design Variable
Reliability - Based Robust Design Optimization of Centrifugal Pump Impeller for Performance Improvement considering Uncertainties in Design Variable M.Balamurugan Assistant Professor, Government College
More informationANSYS AIM Tutorial Turbulent Flow Over a Backward Facing Step
ANSYS AIM Tutorial Turbulent Flow Over a Backward Facing Step Author(s): Sebastian Vecchi, ANSYS Created using ANSYS AIM 18.1 Problem Specification Pre-Analysis & Start Up Governing Equation Start-Up Geometry
More informationCFD STUDY OF MIXING PROCESS IN RUSHTON TURBINE STIRRED TANKS
Third International Conference on CFD in the Minerals and Process Industries CSIRO, Melbourne, Australia 10-12 December 2003 CFD STUDY OF MIXING PROCESS IN RUSHTON TURBINE STIRRED TANKS Guozhong ZHOU 1,2,
More informationTutorial: Hydrodynamics of Bubble Column Reactors
Tutorial: Introduction The purpose of this tutorial is to provide guidelines and recommendations for solving a gas-liquid bubble column problem using the multiphase mixture model, including advice on solver
More informationFlow characteristics and performance evaluation of butterfly valves using numerical analysis
IOP Conference Series: Earth and Environmental Science Flow characteristics and performance evaluation of butterfly valves using numerical analysis To cite this article: S Y Jeon et al 2010 IOP Conf. Ser.:
More informationInfluence of Relevant Fluid Parameters on Pressure Pulsation of a Variable Lubricant Vane Pump
Influence of Relevant Fluid Parameters on Pressure Pulsation of a Variable Lubricant Vane Pump Thomas Fischer, development/calculation Jan Fischer, development/testing Nico Jäkel, development/construction
More informationPutting the Spin in CFD
w h i t e p a p e r Putting the Spin in CFD insight S U M MARY Engineers who design equipment with rotating components need to analyze and understand the behavior of those components if they want to improve
More informationSOLIDWORKS SIMULATION
SOLIDWORKS SIMULATION Innovation is about taking chances, not taking risks Scootchi by Curventa Designworks LTD What if? is the question that fuels innovation. SolidWorks Simulation software takes the
More informationThree Dimensional Numerical Simulation of Turbulent Flow Over Spillways
Three Dimensional Numerical Simulation of Turbulent Flow Over Spillways Latif Bouhadji ASL-AQFlow Inc., Sidney, British Columbia, Canada Email: lbouhadji@aslenv.com ABSTRACT Turbulent flows over a spillway
More informationAnalysis of Fluid-Structure Interaction Effects of Liquid-Filled Container under Drop Testing
Kasetsart J. (Nat. Sci.) 42 : 165-176 (2008) Analysis of Fluid-Structure Interaction Effects of Liquid-Filled Container under Drop Testing Chakrit Suvanjumrat*, Tumrong Puttapitukporn and Satjarthip Thusneyapan
More informationOrbital forming of SKF's hub bearing units
Orbital forming of SKF's hub bearing units Edin Omerspahic 1, Johan Facht 1, Anders Bernhardsson 2 1 Manufacturing Development Centre, AB SKF 2 DYNAmore Nordic 1 Background Orbital forming is an incremental
More informationTutorial 1: Welded Frame - Problem Description
Tutorial 1: Welded Frame - Problem Description Introduction In this first tutorial, we will analyse a simple frame: firstly as a welded frame, and secondly as a pin jointed truss. In each case, we will
More informationAnalysis of fluid-solid coupling vibration characteristics of probe based on ANSYS Workbench
Analysis of fluid-solid coupling vibration characteristics of probe based on ANSYS Workbench He Wang 1, a, Changzheng Zhao 1, b and Hongzhi Chen 1, c 1 Shandong University of Science and Technology, Qingdao
More informationSPEED-UP GEARBOX SIMULATIONS BY INTEGRATING SCORG. Dr. Christine Klier, Sahand Saheb-Jahromi, Ludwig Berger*
SPEED-UP GEARBOX SIMULATIONS BY INTEGRATING SCORG Dr. Christine Klier, Sahand Saheb-Jahromi, Ludwig Berger* CFD SCHUCK ENGINEERING Engineering Services in computational fluid Dynamics (CFD) 25 employees
More informationOptimizing Bio-Inspired Flow Channel Design on Bipolar Plates of PEM Fuel Cells
Excerpt from the Proceedings of the COMSOL Conference 2010 Boston Optimizing Bio-Inspired Flow Channel Design on Bipolar Plates of PEM Fuel Cells James A. Peitzmeier *1, Steven Kapturowski 2 and Xia Wang
More informationONE DIMENSIONAL (1D) SIMULATION TOOL: GT-POWER
CHAPTER 4 ONE DIMENSIONAL (1D) SIMULATION TOOL: GT-POWER 4.1 INTRODUCTION Combustion analysis and optimization of any reciprocating internal combustion engines is too complex and intricate activity. It
More informationLab 9: FLUENT: Transient Natural Convection Between Concentric Cylinders
Lab 9: FLUENT: Transient Natural Convection Between Concentric Cylinders Objective: The objective of this laboratory is to introduce how to use FLUENT to solve both transient and natural convection problems.
More informationRotating Moving Boundary Analysis Using ANSYS 5.7
Abstract Rotating Moving Boundary Analysis Using ANSYS 5.7 Qin Yin Fan CYBERNET SYSTEMS CO., LTD. Rich Lange ANSYS Inc. As subroutines in commercial software, APDL (ANSYS Parametric Design Language) provides
More informationNumerische Untersuchungen von Windkraftanlagen: Leistung, Wake und Steuerungsstrategien
Fachtagung Lasermethoden in der Strömungsmesstechnik 8. 10. September 2015, Dresden Numerische Untersuchungen von Windkraftanlagen: Leistung, Wake und Steuerungsstrategien Numerical Investigations of Wind
More informationWorkshop 15. Single Pass Rolling of a Thick Plate
Introduction Workshop 15 Single Pass Rolling of a Thick Plate Rolling is a basic manufacturing technique used to transform preformed shapes into a form suitable for further processing. The rolling process
More informationCFD design tool for industrial applications
Sixth LACCEI International Latin American and Caribbean Conference for Engineering and Technology (LACCEI 2008) Partnering to Success: Engineering, Education, Research and Development June 4 June 6 2008,
More informationStudy on the Design Method of Impeller on Low Specific Speed Centrifugal Pump
Send Orders for Reprints to reprints@benthamscience.ae 594 The Open Mechanical Engineering Journal, 2015, 9, 594-600 Open Access Study on the Design Method of Impeller on Low Specific Speed Centrifugal
More informationCFD Analysis of conceptual Aircraft body
CFD Analysis of conceptual Aircraft body Manikantissar 1, Dr.Ankur geete 2 1 M. Tech scholar in Mechanical Engineering, SD Bansal college of technology, Indore, M.P, India 2 Associate professor in Mechanical
More informationNumerical Study of Turbulent Flow over Backward-Facing Step with Different Turbulence Models
Numerical Study of Turbulent Flow over Backward-Facing Step with Different Turbulence Models D. G. Jehad *,a, G. A. Hashim b, A. K. Zarzoor c and C. S. Nor Azwadi d Department of Thermo-Fluids, Faculty
More informationApplications of ICFD solver by LS-DYNA in Automotive Fields to Solve Fluid-Solid-Interaction (FSI) Problems
Applications of ICFD solver by LS-DYNA in Automotive Fields to Solve Fluid-Solid-Interaction (FSI) Problems George Wang(1 ), Facundo del Pin(2), Inaki Caldichoury (2), Prince Rodriguez(3), Jason Tippie
More informationExpress Introductory Training in ANSYS Fluent Workshop 06 Using Moving Reference Frames and Sliding Meshes
Express Introductory Training in ANSYS Fluent Workshop 06 Using Moving Reference Frames and Sliding Meshes Dimitrios Sofialidis Technical Manager, SimTec Ltd. Mechanical Engineer, PhD PRACE Autumn School
More informationCold Flow Simulation Inside an SI Engine
Tutorial 12. Cold Flow Simulation Inside an SI Engine Introduction The purpose of this tutorial is to illustrate the case setup and solution of the two dimensional, four stroke spark ignition (SI) engine
More informationISSN(PRINT): ,(ONLINE): ,VOLUME-1,ISSUE-1,
NUMERICAL ANALYSIS OF THE TUBE BANK PRESSURE DROP OF A SHELL AND TUBE HEAT EXCHANGER Kartik Ajugia, Kunal Bhavsar Lecturer, Mechanical Department, SJCET Mumbai University, Maharashtra Assistant Professor,
More informationObject Oriented Simulation of Multiphase Flow
Object Oriented Simulation of Multiphase Flow P.Klebert and O.J.Nydal Norwegian University of Science and Technology (NTNU) 7491 Trondheim Norway Abstract Pipelines in offshore oil and gas production systems
More informationDATA SOLUTION FOR TURBINE SAFETY
DATA SOLUTION FOR TURBINE SAFETY Adrian POPA 1 Ionut-Cristian SCURTU 2 Beazit ALI 3 George NOVAC 4 1 Associate Professor PhD. Eng. Mircea cel Batran Naval Academy, Constanta, Romania, adrian.popa@anmb.ro
More informationGear interlocking effect study using CFD
Gear interlocking effect study using CFD Peyman Jafarian M.Sc. Simulation Engineer Vicura AB, Sweden ABSTRACT Estimating the drag loss and predicting the oil flow distribution within the transmission has
More informationInvestigation of the critical submergence at pump intakes based on multiphase CFD calculations
Advances in Fluid Mechanics X 143 Investigation of the critical submergence at pump intakes based on multiphase CFD calculations P. Pandazis & F. Blömeling TÜV NORD SysTec GmbH and Co. KG, Germany Abstract
More informationNumerical Simulations of Granular Materials Flow around Obstacles: The role of the interstitial gas
Numerical Simulations of Granular Materials Flow around Obstacles: The role of the interstitial gas Avi Levy, Dept. Mech. Eng., Ben Gurion University, Beer Sheva, Israel. Mohamed Sayed, CHC, National Research
More informationCOMPUTATIONAL FLUID DYNAMICS USED IN THE DESIGN OF WATERBLAST TOOLING
2015 WJTA-IMCA Conference and Expo November 2-4 New Orleans, Louisiana Paper COMPUTATIONAL FLUID DYNAMICS USED IN THE DESIGN OF WATERBLAST TOOLING J. Schneider StoneAge, Inc. Durango, Colorado, U.S.A.
More informationCFD modelling of thickened tailings Final project report
26.11.2018 RESEM Remote sensing supporting surveillance and operation of mines CFD modelling of thickened tailings Final project report Lic.Sc.(Tech.) Reeta Tolonen and Docent Esa Muurinen University of
More informationUsing three-dimensional CURVIC contact models to predict stress concentration effects in an axisymmetric model
Boundary Elements XXVII 245 Using three-dimensional CURVIC contact models to predict stress concentration effects in an axisymmetric model J. J. Rencis & S. R. Pisani Department of Mechanical Engineering,
More informationMECHATRONICS SYSTEM ENGINEERING FOR CAE/CAD, MOTION CONTROL AND DESIGN OF VANE ACTUATORS FOR WATER ROBOT APPLICATIONS
MECHATRONICS SYSTEM ENGINEERING FOR CAE/CAD, MOTION CONTROL AND DESIGN OF VANE ACTUATORS FOR WATER ROBOT APPLICATIONS Finn CONRAD and Francesco ROLI Department of Mechanical Engineering, Technical University
More informationTutorial: Simulating a 3D Check Valve Using Dynamic Mesh 6DOF Model And Diffusion Smoothing
Tutorial: Simulating a 3D Check Valve Using Dynamic Mesh 6DOF Model And Diffusion Smoothing Introduction The purpose of this tutorial is to demonstrate how to simulate a ball check valve with small displacement
More informationSimulation of Automotive Fuel Tank Sloshing using Radioss
Simulation of Automotive Fuel Tank Sloshing using Radioss Prashant V. Kulkarni CAE Analyst Tata Motors. Pimpri, Pune - 411018, India Sanjay S. Patil Senior Manager Tata Motors. Pimpri, Pune - 411018, India
More informationSimulation of Turbulent Flow over the Ahmed Body
1 Simulation of Turbulent Flow over the Ahmed Body ME:5160 Intermediate Mechanics of Fluids CFD LAB 4 (ANSYS 18.1; Last Updated: Aug. 18, 2016) By Timur Dogan, Michael Conger, Dong-Hwan Kim, Maysam Mousaviraad,
More informationAPPLICATION OF CNC MILLING IN MANUFACTURING TURBINE BLADES
International Journal of Civil Engineering and Technology (IJCIET) Volume 8, Issue 5, May 2017, pp. 801 808, Article ID: IJCIET_08_05_089 Available online at http://www.iaeme.com/ijciet/issues.asp?jtype=ijciet&vtype=8&itype=5
More information30 th Anniversary Event. New features in Opera By Nigel Atkinson, PhD. OPTIMIZER Automatically selects and manages multiple goalseeking
FEA ANALYSIS General-purpose multiphysics design and analysis software for a wide range of applications OPTIMIZER Automatically selects and manages multiple goalseeking algorithms INTEROPERABILITY Built-in
More informationExpress Introductory Training in ANSYS Fluent Workshop 07 Tank Flushing
Express Introductory Training in ANSYS Fluent Workshop 07 Tank Flushing Dimitrios Sofialidis Technical Manager, SimTec Ltd. Mechanical Engineer, PhD PRACE Autumn School 2013 - Industry Oriented HPC Simulations,
More informationFirst Steps - Ball Valve Design
COSMOSFloWorks 2004 Tutorial 1 First Steps - Ball Valve Design This First Steps tutorial covers the flow of water through a ball valve assembly before and after some design changes. The objective is to
More informationSIMULATION OF FLOW AROUND KCS-HULL
SIMULATION OF FLOW AROUND KCS-HULL Sven Enger (CD-adapco, Germany) Milovan Perić (CD-adapco, Germany) Robinson Perić (University of Erlangen-Nürnberg, Germany) 1.SUMMARY The paper describes results of
More informationEstimating Vertical Drag on Helicopter Fuselage during Hovering
Estimating Vertical Drag on Helicopter Fuselage during Hovering A. A. Wahab * and M.Hafiz Ismail ** Aeronautical & Automotive Dept., Faculty of Mechanical Engineering, Universiti Teknologi Malaysia, 81310
More informationNUMERICAL COUPLING BETWEEN DEM (DISCRETE ELEMENT METHOD) AND FEA (FINITE ELEMENTS ANALYSIS).
NUMERICAL COUPLING BETWEEN DEM (DISCRETE ELEMENT METHOD) AND FEA (FINITE ELEMENTS ANALYSIS). Daniel Schiochet Nasato - ESSS Prof. Dr. José Roberto Nunhez Unicamp Dr. Nicolas Spogis - ESSS Fabiano Nunes
More informationStress Analysis of Cross Groove Type Constant Velocity Joint
TECHNICAL REPORT Stress Analysis of Cross Groove Type Constant Velocity Joint H. SAITO T. MAEDA The driveshaft is the part that transmits the vehicle's engine torque and rotation to the tires, and predicting
More informationANSYS AIM Tutorial Steady Flow Past a Cylinder
ANSYS AIM Tutorial Steady Flow Past a Cylinder Author(s): Sebastian Vecchi, ANSYS Created using ANSYS AIM 18.1 Problem Specification Pre-Analysis & Start Up Solution Domain Boundary Conditions Start-Up
More informationFlow Field Analysis of Turbine Blade Modeling Based on CFX-Blade Gen
Flow Field Analysis of Turbine Blade Modeling Based on CFX-Blade Gen Liguang Wang 1, 2, a, *, Zhijun Li 1, 2, b, Yu Wang 1, 2, c, Baolin Liu 1, 2, Qin Zhou 1, 2 1 School of Engineering and Technology,
More information